[SJSW]

Hi~

I drew a mesh shaped like the attached file "Pic1.jpg" for VOF model using Detached Eddy Simulation(DES) in ANSYS 17 Workbench.
The length of the cell edge is 1mm for all cells.
I tried two methods to created the geometry as drew in the attached file "Pic2.jpg".
Method A is to draw a full geometry and then slice it. Then "select both->right click->Form a New Part".
Method B is to create two bodies and then "select both->right click->Form a New Part".

When it comes to initialization, the following warning showed up:
「
Info: The mesh contains elements that are invalid or of poor quality.

A different numerical scheme will be applied to these elements,
which may affect the quality of the solution. It is recommended
that you consider removing the invalid and poor quality elements
in the mesh.

For more information on the invalid and poor quality elements,
please use the following TUI commands:

/mesh/check

> /mesh/repair-improve/report-poor-elements.
WARNING: The mesh contains high aspect ratio quadrilateral,
hexahedral, or polyhedral cells.
The default algorithm used to compute the wall
distance required by the turbulence models might
produce wrong results in these cells.
Please inspect the wall distance by displaying the
contours of the 'Cell Wall Distance' at the
boundaries. If you observe any irregularities we
recommend the use of an alternative algorithm to
correct the wall distance.
Please select /solve/initialize/repair-wall-distance
using the text user interface to switch to the
alternative algorithm.
」

If the turbulence model was changed to k-epsilon, this warning will not show up.

For now, I don't know what the reason is.
If the turbulence model matters?
or the meshing steps went wrong? need some merge?

In Text User Interface,I used command "mesh/check". "left-handed faces detected" and "WARNING: Mesh check failed" showed up.
Then use "solve/initialize/repair-wall-distance".
Then use "mesh/check", still "left-handed faces detected" and "WARNING: Mesh check failed" showed up.
Then use "/mesh/repair-improve/repair".
Then use "/mesh/check" and no left-handed faces detected.

Is it OK now? @@ is there something missing?
Honestly speaking, I don't know what happened.
orz

[Светлана]

What program did you use for creating your mesh?

[SJSW]

Originally Posted by Светлана

What program did you use for creating your mesh?

Component systems->Mesh

I don't know is it ICEM or just ANSYS Meshing?
The title of this program/feature in Workbench is "B: Mesh- Meshing [ANSYS ICEM CFD]".
However, opening the Help manual from the menu bar, it shows "Meshing User's Guide".
@@

[Светлана]

This means you used ICEM. Use edit mesh → check mesh feature to view the problematic mesh regions.

Just to confirm, you are modelling this in 2d (not 3d with symmetry condition), correct?

As a personal recommendation, I would suggest to use a non-uniform mesh distribution such as shown here.

[SJSW]

Originally Posted by Светлана

This means you used ICEM. Use edit mesh → check mesh feature to view the problematic mesh regions.

Just to confirm, you are modelling this in 2d (not 3d with symmetry condition), correct?

As a personal recommendation, I would suggest to use a non-uniform mesh distribution such as shown here.

Yes, this model is 2D.

The Graphic User Interface(GUI) is like the attached file "pic3.jpg".
It seems not ICEM. @@
I will try to find the function "mesh->check" you suggested.

Orinially, this model is for supersonic under-water flow and boundary layer was assumed to be not important.
I will try to use "inflation" in Meshing.

[LuckyTran]

You did some commands out of the proper sequence, but you should be ok now. Let me explain what each does.

Originally Posted by SJSW

1.In Text User Interface,I used command "mesh/check". "left-handed faces detected" and "WARNING: Mesh check failed" showed up.
2.Then use "solve/initialize/repair-wall-distance".
3.Then use "mesh/check", still "left-handed faces detected" and "WARNING: Mesh check failed" showed up.
4.Then use "/mesh/repair-improve/repair".
5.Then use "/mesh/check" and no left-handed faces detected.

1. You ran the mesh check and it failed
2 You tried to change a numerical setting (the hint that it is numerical is that you are in solve/initialize), which doesn't do anything to the mesh
3. You ran the mesh check again. Of course the mesh check will again fail because it is the exact same mesh as before.
4. You finally ran the repair utility (note that you're not in mesh/check and not solve/initialize)
5. Now when you check the mesh, it's ok because the mesh has been repaired.

The high aspect ratio cells WARNING is just a warning. Usually you mesh this way intentionally and it is expected. I.e. you often have super high aspect ratios cells because of wall clustering to achieve a small y+. If you don't think you have high aspect ratio cells however, then you should go back to the mesher and see what happened because you clearly do. The warning appears when you have aspect ratios around 25-ish or more.

Btw your geometry looks very simple. I would spend some effort to learn how to generate good meshes from the start to avoid these errors.