
[Sponsors] 
June 6, 2013, 14:14 
meaning of HbyA

#1 
Senior Member
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 1,506
Blog Entries: 6
Rep Power: 26 
Hi all,
I am not clear about the variable HbyA Code:
volVectorField HbyA("HbyA", U); HbyA = rAU*UEqn().H(); In the 1.6ext version I found the same declaration: Code:
U = rUA*UEqn().h(); Thanks in advance Tobi 

June 6, 2013, 16:07 

#2 
Senior Member
Cyprien
Join Date: Feb 2010
Location: Stanford University
Posts: 245
Rep Power: 10 
Dear Toby,
As you noticed, both lines are similiar. Actually, the notation HbyA has been spread over all the solvers since the latest OF version (OF 2.2.0) for a sake of clarity. Keep in mind that for the computation of NaviersStokes equation, OF uses either PISO or SIMPLE algorithms. The semidiscretized form of the momentum is : where is the diagonal coefficients of the matrix resulting from the discretization of the momentum equation. stands for the nondiagonal coefficient (mainly composed by convective and diffusive terms) and the source terms (the source part of the transient term and other source that appear in UEqn) apart from the pressure gradient. Once this equation has been implicitly solved (the momentum predictor step), the predicted velocity does not satisfy the continuity equation. Moreover, in the previous equation, the pressure field result from the previous time step. Therefore, we are looking for (U,p) that obeys and Assembling this two equations, you can form the pressure equation: and then you reconstruct the velocity with: You clearly remark in this procedure that you use H divided by A or.. HbyA ;) PS: in OF, rAU is the notation for the diagonal coeff of the matrix Best regards, Cyp 

June 6, 2013, 16:23 

#3 
Senior Member
Cyprien
Join Date: Feb 2010
Location: Stanford University
Posts: 245
Rep Power: 10 
I made slides some times ago to explain the PISO loops in OpenFOAM : http://fr.scribd.com/doc/143414962/P...oninOpenFOAM
They are in French but understandable. It uses old OpenFOAM version, that means without the HbyA notation. 

July 5, 2013, 02:45 

#4 
Senior Member
Dongyue Li
Join Date: Jun 2012
Location: Torino, Italy
Posts: 742
Rep Power: 9 

July 5, 2013, 06:24 

#5 
Senior Member
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 1,506
Blog Entries: 6
Rep Power: 26 
Hi all,
as I understand from Cyp 's comment: So your last line should be: Code:
fvScalarMatrix pEqn ( xxx == fvc::div(HbyA) ); Last edited by Tobi; July 6, 2013 at 05:41. 

November 15, 2013, 16:30 

#6 
Senior Member
Cyprien
Join Date: Feb 2010
Location: Stanford University
Posts: 245
Rep Power: 10 

December 24, 2013, 03:41 
thx

#7  
New Member
enzhen zhang
Join Date: Dec 2013
Location: Shanghai,China
Posts: 11
Rep Power: 4 
Quote:


March 14, 2014, 16:26 

#8 
Member
Join Date: Feb 2012
Posts: 49
Rep Power: 6 
Dear Guys,
I'm using the 3step rungekutta scheme to solve Navier Stokes equation. There are some differences in the equations must be solved, but the main equations are same.you can see the equations in the attachment(those equations are put in a for loop, from k=1 to k=3) Also, below you can see my summarized code to solve that, but i don't know how to use coefficients(same as piso loop of icoFoam) ! I would appreciate any idea on how to change my code to something like the piso loop of icoFoam : Code:
while (runTime.loop()) { for (int i = 1 ; i<=3 ; ++i) { U = U + runTime.deltaT() * ( + 2*alpha*fvc::laplacian(nu,U)  2*alpha*fvc::grad(p)  gamma*fvc::div(phi, U)  zeta*fvc::div(phiOld2, UOld2) ); solve(alpha*runTime.deltaT()*fvm::laplacian(nu,Unew)  fvm::Sp(1.,Unew) == //(alpha*runTime.deltaT()) == (1.)*(U) + alpha*runTime.deltaT()*fvc::laplacian(nu,U) ); solve (fvm::laplacian(pPhi) == fvc::div(U)/(2.*alpha*runTime.deltaT()));// pPhi is a pseudo pressure without physical meaning U = Unew  (2.*alpha*runTime.deltaT()*fvc::grad(pPhi)); p += pPhi  alpha*runTime.deltaT()*nu*(fvc::laplacian(pPhi)); adjustPhi(phi, U, p); U.correctBoundaryConditions(); } } //alpha,gamma and zeta change in each of those 3 steps 

March 27, 2016, 06:17 

#9 
Senior Member
Saideep
Join Date: Apr 2015
Location: INDIA
Posts: 147
Rep Power: 3 
Thanks guys for sharing this information!!
I am just going through the implementation of PISO/ PIMPLE in interFoam solver. I could understand and link most part of what is discussed here but confused at parts. Hope you can help me out!! Starting with UEqn.H: fvVectorMatrix UEqn ( fvm::ddt(rho, U) + fvm::div(rhoPhi, U) + turbulence>divDevRhoReff(rho, U) == fvOptions(rho, U) ); Over here we already have a solution for velocity without influence of pressure.{solving NSE excluding variables of pressure and body forces that dont have an explicit U term}. We extract the diagonal{UEqn.A()} and off diagonal portions {UEqn.H()}. Now passing to pEqn.H: We find and link velocity to flux over cell faces.(U > phi) Additionally due to surface tension force induced flux, we add flux to the above calculated flux. {Even here pressure isnt included till now}. Now the pressure corection is directly applied as follows: fvm::laplacian(rAUf, p_rgh) == fvc::div(phiHbyA) /*we are finding for p_rgh*/ From this further correction to flux and U from the found out pressure is calculated to get the conservative velocity. My question, 1. In all explanations I have had browsed through, they explicitly mention usage of pressure twice. One as an approximate and one found as a real value. But from interFoam solver I see only once the usage of pressure and it is the corrected pressure that we are solving for. {above equation, laplacian pressure} 2. What are nOuterCorrectors, nCorrectors variablels? I see their default definitions but where are we specifying the loop? I guess it has something to do with pimple.correct() loop but how are the variables being used? Thanks and interested to hear your views, Saideep 

March 27, 2016, 18:24 

#10 
Senior Member
Tobias Holzmann
Join Date: Oct 2010
Location: Leoben (Austria)
Posts: 1,506
Blog Entries: 6
Rep Power: 26 
For nouter and ncorr See my blog
__________________
Best regards, Tobias Holzmann Some interesting OpenFOAM tutorials and videos on www.Holzmanncfd.de 

Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Meaning of Ychar and Ypmma  aylalisa  OpenFOAM PreProcessing  2  October 20, 2013 05:49 
what is the meaning of this?!??!!?  adambarfi  OpenFOAM Running, Solving & CFD  9  September 13, 2013 10:53 
What's meaning of UDF FUNCTION  zhaoxinyu  Fluent UDF and Scheme Programming  0  March 31, 2010 08:04 
want to know meaning  Sangamesh  CDadapco  0  May 15, 2007 05:15 
What's the meaning of "combustion scalar"and....  cfdbeginner  CFX  0  November 27, 2003 10:02 