|
[Sponsors] |
October 12, 2006, 11:26 |
export to Paraview own solver
|
#1 |
Guest
Posts: n/a
|
What format should i use to export to Paraview? I am developing my own solver and i am looking for the best format to use. Paraview has native VTK files, but i could also use Ensight or others. What would be the best choice?
Regards, Nico |
|
October 12, 2006, 11:44 |
re: export to Paraview own solver
|
#2 |
Guest
Posts: n/a
|
In my opinion, Ensight's format is the easiest to understand, implement and use (even for parallel post-processing). I've put some ParaView stuffs, including the Fortran routines I use to export Ensight's file, available in http://www.nacad.ufrj.br/~rnelias/paraview/
Cheers Renato. |
|
October 12, 2006, 17:22 |
re: export to Paraview own solver
|
#3 |
Guest
Posts: n/a
|
Where can we find the details of Ensights format, could you provide some links. My solver exports in fieldview, i wish to add more exports to it.
|
|
October 12, 2006, 18:59 |
re: export to Paraview own solver
|
#4 |
Guest
Posts: n/a
|
I included the Ensight's format description in the http://www.nacad.ufrj.br/~rnelias/pa...htRoutines.zip file. Take a look ;o)
Regards Renato. |
|
October 12, 2006, 20:16 |
re: export to Paraview own solver
|
#5 |
Guest
Posts: n/a
|
obrigado pela sua ajuda.
|
|
October 13, 2006, 21:08 |
re: export to Paraview own solver
|
#6 |
Guest
Posts: n/a
|
Hi Renato,
I would like to export elmer data to VTK format so that I can use paraview to view the results. I have no idea of VTK format. Do you have any fortran code to show how to export data to VTK format? Thanks! phsieh2005 |
|
October 19, 2006, 13:10 |
re: export to Paraview own solver
|
#7 |
Guest
Posts: n/a
|
Any ideas why this is not working?, the ascii version is working fine, but when i try binary its crashing paraview.
Regards, Nicolas integer::vac (1:nct,0:8) Character*80 :: buffer integer::i,j real*4,dimension(,allocatable :: xv,yv,zv allocate(xv(1:nvt),yv(1:nvt),zv(1:nvt) ) !---Write geometry file. engold.geo ensight_geometry='engold.geo'; Open(1,file=ensight_geometry,form='binary'); buffer='Fortran Binary'; Write(1) buffer; buffer='Exported from Solver'; Write(1) buffer; buffer='Nicolas ROUSSELON 2006'; Write(1) buffer; buffer='node id assign';Write(1) buffer; buffer='element id assign'; Write(1) buffer; buffer='part'; Write(1) buffer; i=1; Write(1) i; buffer='fluid'; Write(1) buffer; buffer='coordinates'; Write(1) buffer; !NODES Write(1) nvt; Write(1) (xv(i), i=1,nvt) Write(1) (yv(i), i=1,nvt) Write(1) (zv(i), i=1,nvt) !ELEMENTS buffer='hexa8';Write(1) buffer; Write(1) nct; Do j=1,nct Write(1) (vac(j,i),i=1,vac(j,0)),8 EndDo close(1) |
|
January 17, 2013, 13:51 |
|
#8 |
New Member
Bart Paarhuis
Join Date: Jan 2013
Location: Netherlands
Posts: 3
Rep Power: 13 |
Hi Renato,
I compiled and ran your testprogram 'fortran_ensight_test' using CVF on Windows XP. But paraview crashes reading the binary files. I tried all available numeric formats for unformatted data (compiler option). But it won't help. What compiler/system combination did you use? Thanks, Bart |
|
January 17, 2013, 15:12 |
|
#9 |
New Member
Bart Paarhuis
Join Date: Jan 2013
Location: Netherlands
Posts: 3
Rep Power: 13 |
After a lot of trial and error, I finally got the ensight binary files to work with the CVF compiler:
- open(...,form='binary',convert='BIG_ENDIAN') for the geometry and result files instead of open(...,form='unformatted') - and using 'C Binary' instead of 'Fortran Binary' as the first line in the geometry file |
|
October 7, 2016, 11:15 |
|
#10 |
Senior Member
|
Dear Renato, I know that this post is pretty old, but I am starting with Paraview after years working with Tecplot. My main challenge is to write my scalar field to Paraview. I downloaded the EnsightRoutines and I see three files. EnisghtCase, WriteEnsightMeshBin and WriteEnsightResults. I am totally lost with them all. Which of these do you recommend me to use to write my own ploting subroutine in FORTRAN.
Thanks in advance for you all!! |
|
October 9, 2016, 14:28 |
|
#11 |
New Member
Bart Paarhuis
Join Date: Jan 2013
Location: Netherlands
Posts: 3
Rep Power: 13 |
Hi Juliome,
It's not that difficult. The 'cas' file contains some general information, like what is the dataformat and the name of the file which contains the grid and a file containing the actual data (in your case your scalar). I guess you can find more info on the internet with details of the files. To test you better first write in ascii and if that works you write the grid and cas file as binary. Regards, Bart Example: # # your comments # FORMAT type: ensight GEOMETRY model: yourgridfile.grid VARIABLE scalar per element: scalar_name yourdatafile_****.dat TIME time set: 1 ts_description number of steps: 1 filename start number: 0 filename increment: 1 time values: 0.00000E+00 |
|
October 10, 2016, 12:11 |
|
#12 |
Senior Member
|
Thank you very much for the reply. Can we use EnsightGold for Paraview? Since I basically use structured grid and transient simulations for CFD, what format is the most recommended for that purpose?
|
|
April 8, 2017, 23:59 |
|
#13 |
New Member
Abdullah Karimi
Join Date: Nov 2010
Posts: 29
Rep Power: 15 |
EnsightGold should work fine in Paraview. In fact, I preferably use this format when exporting file from Fluent and then import into Paraview for visualization.
|
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Export Particle Data From Fluent to Paraview | liliana | FLUENT | 2 | November 18, 2016 09:14 |
Export Surface LIC data from Paraview to Tecplot? | hxaxtma | Tecplot | 1 | July 2, 2014 04:55 |
Paraview version update errors | Dan Pearce | OpenFOAM Installation | 5 | January 8, 2014 05:47 |
[ICEM] Export mesh for IDEAS solver | loic | ANSYS Meshing & Geometry | 2 | July 29, 2011 17:08 |
Working directory via command line | Luiz | CFX | 4 | March 6, 2011 20:02 |