CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > STAR-CCM+

Moving piston inside cylinder

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   November 10, 2013, 03:16
Default Moving piston inside cylinder
  #1
New Member
 
Join Date: Jun 2010
Posts: 4
Rep Power: 7
Hope2010 is on a distinguished road
Hi everyone,

Hope one of the expert help me and show me step by step how can i simulate a moving piston inside a cylinder using STAR CCM+. There is one inlet and an exit, the entering flow is oil which should push the piston.


Many thanks,

Hope2010
Hope2010 is offline   Reply With Quote

Old   November 10, 2013, 16:37
Default
  #2
cwl
Member
 
Chaotic Water
Join Date: Jul 2012
Posts: 51
Rep Power: 5
cwl is on a distinguished road
Send a message via Skype™ to cwl
While experts are away - i advice you to read about Overset Mesh; its around p. 2381 in User Guide.
cwl is offline   Reply With Quote

Old   November 11, 2013, 00:14
Default
  #3
New Member
 
Join Date: Jun 2010
Posts: 4
Rep Power: 7
Hope2010 is on a distinguished road
Thanks cwl ,
Hope2010 is offline   Reply With Quote

Old   November 11, 2013, 19:05
Default
  #4
New Member
 
Marco
Join Date: Aug 2013
Posts: 13
Rep Power: 3
Mark_89 is on a distinguished road
The simulation of a moving piston in a cylinder can be very difficult in star ccm+ because the software has some problems when work with morphing mesh. However the diffiCulty is related to two variables: 1) the difficulty of the simulation is proportional to compression ratio:the higher the compression ratio, the greater the difficulty. 2)the difficulty increases also if you have to use valves movements, especially if you start from closed valves, open them and close again.
the process is:
1) you can prepare a region composed by intake valve, exhaust valve, piston crown and the other boundaries. Impose the physics (3 gradients, turbulent, constant density for your case, implicit unsteady, segregated flow ecc) and generate the mesh (basic size about 2 mm). Go to tools-motion and select morphing. One click to region and you change motion menu from stationary to morphing (you can find motion menu into physics condition folder relative to the region). Then For each mobile boundary (intake valve, exhaust valve and piston crown) go to physics condition and impose morpher-displacement. Go to tools tables and import three tables (time); each table contains the law motion of the moving boundaries (create three .csv files with 4 headers, named "column0", "column1", "column2", "time"....you have to insert respectively the x-y-z displacemet in metre and time in seconds). Go to each moving boundary- physics values-morpher-table (time)- specify its relative table. Remesh. Solvers-implicit unsteady-time step between 0.001 s and 0.00001 s (start from smaller time step). Run simulation.


while the simulation is running you can see that cells mesh are deforming and probably they will have negative volume. When this happens, go to representation, click to volume mesh and extract boundary surface, export surface. One right click to initial surface-replace surface with that you have just exported (choose metre m, and tick the link above between the two choices). Remesh (surface and volume). In some cases this technique is not sufficient, BUT there are other techniques to bypass the problem of the negative volume cells that i haven't explained here. For now Try this and tell me if you have need. I'm sorry for my horrible english!
G O O D L U C K
Mark_89 is offline   Reply With Quote

Old   November 13, 2013, 00:48
Default
  #5
New Member
 
Join Date: Jun 2010
Posts: 4
Rep Power: 7
Hope2010 is on a distinguished road
Thanks Mark ,
Hope2010 is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
simulation of piston motion inside a hydraulic cylinder mosman Main CFD Forum 0 August 7, 2011 01:40
moving mesh rolling piston JohannVV FLUENT 4 November 11, 2010 10:46
Moving a Cylinder in cross flow after solving Dynamics equations of motion maruthamuthu_venkatraman OpenFOAM 1 November 19, 2009 14:55
Confined or moving cylinder Mohamed GUEROUACHE Main CFD Forum 1 October 23, 1999 15:20
Confined or moving cylinder Mohamed GUEROUACHE Main CFD Forum 0 October 19, 1999 11:00


All times are GMT -4. The time now is 05:04.