CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > ANSYS Meshing & Geometry

[ICEM] Solid wall meshing in T junction

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree2Likes
  • 2 Post By energy382

Reply
 
LinkBack Thread Tools Display Modes
Old   January 1, 2013, 04:45
Default Solid wall meshing in T junction
  #1
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
Hello Friends,

I am currently working on fluid flows in T junction piping system. I wanted to create mesh for the solid piping part along with the fluid part inside the pipe. Can someone suggest me a blocking strategy for doing this? I have attached a picture of the T junction pipe along with this post for your reference. Thank you.
Attached Images
File Type: png t-pipe-junction.png (5.7 KB, 55 views)
selvam2487 is offline   Reply With Quote

Old   January 1, 2013, 08:22
Default
  #2
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,916
Blog Entries: 6
Rep Power: 38
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Draw ogrid for thickness
Far is offline   Reply With Quote

Old   January 1, 2013, 09:40
Default Solid pipe blocking
  #3
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
Hello Far,

You mean two O grids (one for the fluid domain and one for the solid domain)? If my understanding is wrong, kindly correct me. It would be more understandable for me if you could attach some pictures.
Also, I would like to thank you for your suggestions about meshing in a T junction pipe in my previous posts. Based on your suggestion, I am able to create a mesh with an angle of 41° and a quality of 0.62. Now I am trying to create a complete meshing of solid pipe with fluid flow inside it, which is what my work is all about.
selvam2487 is offline   Reply With Quote

Old   January 1, 2013, 09:48
Default
  #4
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,916
Blog Entries: 6
Rep Power: 38
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
If you can attach .tin I will try
Far is offline   Reply With Quote

Old   January 1, 2013, 15:39
Default tin file for T junction with a thickness
  #5
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
Hello Far,

I am attaching the tin file along with this post. Kindly have a look at it. Once again thank you very much for your help.
Attached Files
File Type: zip T_Jn_thickness.zip (44.2 KB, 10 views)
selvam2487 is offline   Reply With Quote

Old   January 2, 2013, 05:08
Default
  #6
Senior Member
 
Christoph
Join Date: May 2011
Location: Germany
Posts: 182
Rep Power: 9
energy382 is on a distinguished road
Why do you want to model the solid part as well? Is there any heat transfer?

If so (and if it's a thin surface), you can do it with a another, more accurate approach.
energy382 is offline   Reply With Quote

Old   January 2, 2013, 05:12
Default Solid pipe and fluid blocking
  #7
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
Yes, there is a conjugate heat transfer between the pipe and the fluid near the wall. Because of the temperature fluctuations occurring near the solid wall, the pipe fails after certain thousand hours of operation which is generally called thermal fatigue. So I am interested in modeling both fluid and solid parts. Could you kindly help me as to how to do it? Thank you very much in advance for your help.

P.S: The thickness of the cold fluid pipe (branch pipe) is 1.1 mm while the thickness of the hot fluid pipe (main pipe) is 8.2 mm

Last edited by selvam2487; January 2, 2013 at 05:15. Reason: left out an information
selvam2487 is offline   Reply With Quote

Old   January 2, 2013, 05:26
Default
  #8
Senior Member
 
Christoph
Join Date: May 2011
Location: Germany
Posts: 182
Rep Power: 9
energy382 is on a distinguished road
Ok, that's an easy one. I'll take a look on it as soon as I'm back in office. Any blocking so far?!
energy382 is offline   Reply With Quote

Old   January 2, 2013, 05:32
Default T junction with a thickness
  #9
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
No. I have done blocking for T junction with only fluid flow (i.e., no thickness in the pipe walls). For T junctions with wall thickness, I do not know how to implement a blocking strategy. I have attached the ANSYS ICEM file in the present thread when replying to another member in this forum.
selvam2487 is offline   Reply With Quote

Old   January 2, 2013, 07:09
Default
  #10
Senior Member
 
Christoph
Join Date: May 2011
Location: Germany
Posts: 182
Rep Power: 9
energy382 is on a distinguished road
your geometry is not closed at t-junction. Blank part T_P and you'll see it. Please confirm.
Attached Files
File Type: zip T_Jn_thickness.zip (46.0 KB, 4 views)
energy382 is offline   Reply With Quote

Old   January 2, 2013, 08:13
Default T junction with a thickness
  #11
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
Hello,

Thank you very much for pointing out the mistake in the geometry. I think I have corrected it and I am attaching it along with this post. Kindly have a look at it and let me know if it is ok.
Attached Files
File Type: zip T_Jn_thickness.zip (59.3 KB, 7 views)
selvam2487 is offline   Reply With Quote

Old   January 2, 2013, 10:22
Default
  #12
Senior Member
 
Christoph
Join Date: May 2011
Location: Germany
Posts: 182
Rep Power: 9
energy382 is on a distinguished road
I've attached the mesh.

You've to adjust edge paramters (especially within boundary layer => y+ should be < 1 for heat transfer )

Regards,
Christoph
Attached Files
File Type: zip T_Jn_thickness.zip (79.1 KB, 23 views)
Far and selvam2487 like this.
energy382 is offline   Reply With Quote

Old   January 3, 2013, 05:14
Default
  #13
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
Dear Christoph,

Thank you very much for your help. I am currently working on the mesh you sent me. It is simple and understandable.

Regards,
Karthick
selvam2487 is offline   Reply With Quote

Old   January 3, 2013, 09:10
Default
  #14
Member
 
Karthick Selvam
Join Date: Oct 2012
Location: Germany
Posts: 48
Rep Power: 4
selvam2487 is on a distinguished road
Send a message via Skype™ to selvam2487
Dear Christoph,

I have a doubt regarding a part that you have created. What does the part T_P mean? I see it on the outer surface of the cold pipe. Also, how did you do the blocking for the solid and fluid part. I think you applied three blockings (two for solid outer wall and inner wall) and one for the fluid domain along with the O grid. I tried it and it is showing me the option of merging or replacing the earlier blocking that I had done. Could you please explain me how to do the blocking strategy you have implemented?

Last edited by selvam2487; January 3, 2013 at 09:43. Reason: to add another question
selvam2487 is offline   Reply With Quote

Old   January 3, 2013, 10:13
Default
  #15
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,916
Blog Entries: 6
Rep Power: 38
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
Please find the blocking attached herewith.

I have done some more steps as compared to previous only fluid blocking

1. Made two o-grid instead of one

2. Solid blocks were defined

3. Associated edges to curves. special care was taken at the junction

4. Shared wall between solid and fluid (inner pipe)

5. Due to problems in meshing, i have manually associated the outer pipe faces to corresponding surface(s).


Hier findest du die hiermit Sperrung angebracht.

Ich habe einige weitere Schritte getan, um vorhergehende nur Fluidsperrvorrichtung Vergleich

Ein. Hergestellt zwei o-Grid statt einer

2. Feste Blöcke definiert wurden

3. Zugeordneten Kanten in Kurven. Besondere Sorgfalt wurde an der Kreuzung getroffen

4. Gemeinsame Wand zwischen festen und flüssigen (Innenrohr)

5. Aufgrund von Problemen in kämmendem haben i manuell die Außenrohr Gesichter zu entsprechenden Oberfläche (n) zugeordnet ist.

Mit freundlichen Grüßen
Far (Nicht zu weit)
Attached Files
File Type: zip T_junction_solidfluid_Far.zip (93.4 KB, 16 views)

Last edited by Far; January 3, 2013 at 10:50.
Far is offline   Reply With Quote

Old   January 3, 2013, 10:35
Default
  #16
Far
Super Moderator
 
Far's Avatar
 
Sijal Ahmed Memon (turboenginner@gmail.com)
Join Date: Mar 2009
Location: Islamabad Pakistan
Posts: 3,916
Blog Entries: 6
Rep Power: 38
Far will become famous soon enoughFar will become famous soon enough
Send a message via Skype™ to Far
I am curious to see that how you will handle the solid part in CFD solver !!!
Far is offline   Reply With Quote

Old   January 3, 2013, 10:43
Default
  #17
Senior Member
 
Christoph
Join Date: May 2011
Location: Germany
Posts: 182
Rep Power: 9
energy382 is on a distinguished road
Quote:
Originally Posted by selvam2487 View Post
Dear Christoph,

I have a doubt regarding a part that you have created. What does the part T_P mean? I see it on the outer surface of the cold pipe. Also, how did you do the blocking for the solid and fluid part. I think you applied three blockings (two for solid outer wall and inner wall) and one for the fluid domain along with the O grid. I tried it and it is showing me the option of merging or replacing the earlier blocking that I had done. Could you please explain me how to do the blocking strategy you have implemented?
Du kannst es auf zwei Arten machen:

1. du machst ein O-grid für das Fluid und machst dann nochmal ein O-grid, wobei du hier dann "arround blocking" "abstand=1" und "absolut" wählst. Dann hast du zwei verschachtelte O-grids. Das Äußere weist du dann dem Part "SOLID" zu, das innere O-grid dem Part "FLUID".
Dazu einfach Part-Create New Part-"SOLID"-und dann die Blöcke des äußeren O-grids diesem Part zuweisen.
Dann nur noch die Kanten mit den Kurven verbinden (oder face to surface falls das Netz nicht richtig projeziert wird).

2. du machst zwei getrennte Blockings. Ein 3D-Blocking FLUID und eins fürs SOLID. Dann musst du diese allerdings an den Blockgrenzen verbinden (merge nodes).

Die elegantere Methode ist sicher die Erste, aber die Zweite ist vielleicht etwas übersichtlicher.

Das Netz kannst du dann ja über die Kantenparameter steuern. Du solltest max. grow ratio von 1,2 wählen und auf dein y+ Werte achten. Bei Wärmeübergängen etc. sollten diese nahe an 1 liegen, damit auch die viskose Unterschicht der Grenzschicht aufgelöst wird. Wandfunktionen liefern hier falsche Ergebnisse. Als Turbulenzmodel SST.

Melde dich, falls noch Fragen offen sind zum Thema Vernetzung und/oder Preprocessing

Gruß Christoph
energy382 is offline   Reply With Quote

Reply

Tags
blocking strategy, t junction

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Natural convection in a closed domain STILL NEEDING help! Yr0gErG FLUENT 3 June 12, 2013 02:12
[ANSYS Meshing] Meshing for flat plate immersed solid hamed.majeed ANSYS Meshing & Geometry 0 July 10, 2012 13:32
[ANSYS Meshing] Internal Wall in Ansys Meshing swiss_zhang ANSYS Meshing & Geometry 0 September 28, 2011 07:56
Help needed in meshing for Solid to Fluid Heat Transfer niazaliahmed FLUENT 1 July 28, 2011 08:21
Wall functions Abhijit Tilak Main CFD Forum 6 February 5, 1999 02:16


All times are GMT -4. The time now is 01:10.