CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CD-adapco

ANSA mesh in star 4

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   November 18, 2008, 18:21
Default ANSA mesh in star 4
  #1
alex
Guest
 
Posts: n/a
I have a trouble with import of a mesh created with ANSA in STAR-CD v4. I get form ANSA no information about the boundaries becauese ANSA does not create *.bnd file. List->boundaries shows "0 boundaries". Without boundaries I cannot prescribe th b.c.

Who can give me a hint how I can create boundaries in STAR in a file imported from ANSA in the simplest way? I tryed it in GUI without success.

  Reply With Quote

Old   November 19, 2008, 07:56
Default Re: ANSA mesh in star 4
  #2
alex
Guest
 
Posts: n/a
What I mean here, of course it is possible to define boundaries by clicking on faces or using "create by picking a zone" in prostar. It is very time consuming.

My question is how I can use geometrical information provided in the files imported from ANSA. I tryed to convert shells in prostar using

CHSELL,ALL,1,ALL,1 BSHELL,0,1,ALL,1,0

but it does not work. No shells are converted into boundaries.

Any idea here?
  Reply With Quote

Old   November 19, 2008, 08:39
Default Re: ANSA mesh in star 4
  #3
James
Guest
 
Posts: n/a
I think you are looking for BFIND

Vset news edge

Cdis on vert (to show the edge vertices)

repl

Bfin 1 vx (for boundary 1)

This usually produces the boundaries you want pretty fast.

Remembering that STAR covers uncovered faces in Region 0, you do not have to define all the walls typically.

Note BFIND typically works better on quad surfaces, if you have tri surfaces some of the corners are missed as all three edge vertices are in the Vset.

BCROSS usually sorts these out pretty fast. Also programming the function keys can speed things up when you have simple command sequences.
  Reply With Quote

Old   December 3, 2008, 07:57
Default Re: ANSA mesh in star 4
  #4
steven
Guest
 
Posts: n/a
i believe that you should try another mesh engine....... i believe that a mesh engine of a thirty party company always have problems .....

steven
  Reply With Quote

Old   December 3, 2008, 13:03
Default Re: ANSA mesh in star 4 *NM*
  #5
alex
Guest
 
Posts: n/a
  Reply With Quote

Old   December 3, 2008, 13:10
Default Re: ANSA mesh in star 4
  #6
alex
Guest
 
Posts: n/a
Many thanks on your comments. Principally I would mesh in STAR-CCM+ and solve back in in STAR v4 because the stakeholder of the project is wishing that we use STAR and has no preferences about meshing. I will try it if I have more time.

  Reply With Quote

Old   December 3, 2008, 18:30
Default Re: ANSA mesh in star 4
  #7
Balduin Bankerotti
Guest
 
Posts: n/a
It should be really no problem to use ANSA for meshing as long as you know some prostar commands to define the boundaries.

If you have a shell with cell type 10 on a region you have to use the following commands to define the boundaries with region numer 1 (10-9):


cset news type 10
vset news cset
cset add vset all
cset subs flui
cshell 10 cset
cset news type 10
bshell -9 cset
  Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
ANSA for CFD mesh santosh kangarlan ANSA 23 March 20, 2013 11:39
how to export a mesh from star design to star cd aounallah CD-adapco 4 March 6, 2009 07:22
do I need to mesh in ANSA if using Harpoon/t-grid? boris Main CFD Forum 1 October 13, 2008 05:01
Preprocessor - Ansa? Fab Main CFD Forum 7 July 4, 2006 04:15
Mesh export from pro-STAR to STAR-CCM+ Rostislav CD-adapco 1 November 25, 2005 15:07


All times are GMT -4. The time now is 15:34.