# UDF paraboloid velocity inlet

 Register Blogs Members List Search Today's Posts Mark Forums Read

 May 18, 2003, 13:37 UDF paraboloid velocity inlet #1 rosco Guest   Posts: n/a Hi, I have to put a velocity profile (fully developed) at the inlet of a 3D case but I never use UDF to define boundaries. The profile is like a paraboloid centered at middle of the pipe. I read the UDF chapter on FLuent doc but there's no 3D case example, only 2D as above (definition of a parabolic profile at inlet): ----------------------------- #include "udf.h" DEFINE_PROFILE(inlet_x_velocity, thread, position) { real x[ND_ND]; /* this will hold the position vector */ real y; face_t f; begin_f_loop(f, thread) { F_CENTROID(x,f,thread); y = x[1]; F_PROFILE(f, thread, position) = 20. - y*y/(.0745*.0745)*20.; } end_f_loop(f, thread) } ---------------------------- I don't know how to change that in 3D . Someone could help me by give the right UDF file format in 3D? Thx a lot

 May 18, 2003, 17:19 Re: UDF paraboloid velocity inlet #2 ap Guest   Posts: n/a The x vector contains contains x and y position of the cell centroid in 2D, and x,y,z in 3D. So, if you write your paraboloid in the form z = f(x,y) your x will be the first position (0) of x vector and your y will be the second one (1). So you have to remove the line y = x[1]; and change F_PROFILE(f, thread, position) = 20. - y*y/(.0745*.0745)*20.; in F_PROFILE(f,thread,position) = f(x[0],x[1]); P.S. I'm supposing your pipe axis is along z axis. If you want the code, post the equation of the paraboloid Hi ap

 May 18, 2003, 17:47 Re: UDF paraboloid velocity inlet #3 rosco Guest   Posts: n/a Hi ap The velocity take several values (derived of the mass flow inlet boundary), the diameter of pipe is 10mm , pipe axis is along Z axis. Here is the mesh for the waterblock (a water flow in a copper shape with a maze) to understand situation (inlet in blue and outlet in red color): http://membres.lycos.fr/roscool/forum/temp/mesh.gif Could you put the code for a 1m/s velocity inlet (mean) for example with a typical poiseuille flow shape (paraboloid)? Thx again ap

 May 18, 2003, 20:42 Re: UDF paraboloid velocity inlet #4 ap Guest   Posts: n/a I write what I did so you can check it (did it in a hurry ) I suppose that the origin of reference system is the center of the inlet. If this is not true...translate your mesh with Gambit The general paraboloid form is: z = a*x^2 + b*y^2 + c But in our case a=b because it's axi-symmetric. The vertex of the paraboloid has z = v_max = 2*v_avg, and it's z = 0 for example in (x=0,y=r). So a = b = -v_max/(r^2) c = v_max v_max = 2*v_avg and z = -v_max/(r^2) * (x^2+y^2) + v_max In the code i put -v_max/(r^2) = coeff. Here's the code. Remember it requires you have the origin of your reference system in the center of the inlet pipe. If you need to change diameter and average velocity, change their values in the corresponding #define. #include "udf.h" #define PIPE_DIAMETER 10.e-3 // Set here the diameter of your pipe in meters #define AVG_Z_VELOCITY 1. // Set here the average z velocity at inlet in m/s DEFINE_PROFILE(paraboloid_velocity, thread, position) { real x[ND_ND]; real coeff,r,v_max; face_t f; r = PIPE_DIAMETER/2.; //Calculating radius v_max = 2.*AVG_Z_VELOCITY; //Calculating paraboloid vertex z (max velocity) coeff = -v_max/pow(r,2.); begin_f_loop(f, thread) { F_CENTROID(x,f,thread); F_PROFILE(f, thread, position) = coeff*(pow(x[0],2.) + pow(x[1],2)) + v_max; } end_f_loop(f, thread) } Hi and good work ap

 May 19, 2003, 05:30 Re: UDF paraboloid velocity inlet #5 rosco Guest   Posts: n/a Oki, I understand now how to define each velocity on each face at inlet I'll try that soon, I hope it works Thank you very much ap to help me each time

 September 1, 2011, 02:29 #6 Member   Nirav Join Date: Jul 2011 Posts: 42 Rep Power: 7 thank you for detailed discription of udf for paraboloid

March 24, 2016, 11:48
#7
New Member

Yu Lu
Join Date: Jul 2015
Location: England
Posts: 20
Rep Power: 3
Quote:
 Originally Posted by ap ;106045 I write what I did so you can check it (did it in a hurry ) I suppose that the origin of reference system is the center of the inlet. If this is not true...translate your mesh with Gambit The general paraboloid form is: z = a*x^2 + b*y^2 + c But in our case a=b because it's axi-symmetric. The vertex of the paraboloid has z = v_max = 2*v_avg, and it's z = 0 for example in (x=0,y=r). So a = b = -v_max/(r^2) c = v_max v_max = 2*v_avg and z = -v_max/(r^2) * (x^2+y^2) + v_max In the code i put -v_max/(r^2) = coeff. Here's the code. Remember it requires you have the origin of your reference system in the center of the inlet pipe. If you need to change diameter and average velocity, change their values in the corresponding #define. #include "udf.h" #define PIPE_DIAMETER 10.e-3 // Set here the diameter of your pipe in meters #define AVG_Z_VELOCITY 1. // Set here the average z velocity at inlet in m/s DEFINE_PROFILE(paraboloid_velocity, thread, position) { real x[ND_ND]; real coeff,r,v_max; face_t f; r = PIPE_DIAMETER/2.; //Calculating radius v_max = 2.*AVG_Z_VELOCITY; //Calculating paraboloid vertex z (max velocity) coeff = -v_max/pow(r,2.); begin_f_loop(f, thread) { F_CENTROID(x,f,thread); F_PROFILE(f, thread, position) = coeff*(pow(x[0],2.) + pow(x[1],2)) + v_max; } end_f_loop(f, thread) } Hi and good work ap

This is so detailed thank you!

Just one thing, F_PROFILE(f, thread, position) = coeff*(pow(x[0],2.) + pow(x[1],2)) + v_max

why it's not coeff*(pow(x,2.) + pow(y,2)) + v_max ??

March 30, 2016, 17:28
#8
Senior Member

Join Date: Mar 2015
Posts: 758
Rep Power: 9
Quote:
 Originally Posted by yulu This is so detailed thank you! Just one thing, F_PROFILE(f, thread, position) = coeff*(pow(x[0],2.) + pow(x[1],2)) + v_max why it's not coeff*(pow(x,2.) + pow(y,2)) + v_max ??
The F_CENTROID(x,f,thread) macro returns an array, 'x', of coordinate positions of the centroid of the face. Each value in this array is for a different spatial coordinate: x[0] for x-direction, x[1] for y-direction and x[2] for z-direction (only in 3-D cases).

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post sincity Fluent UDF and Scheme Programming 47 April 27, 2016 11:09 Sing FLUENT 10 October 14, 2015 20:24 zumaqiong Fluent UDF and Scheme Programming 1 June 4, 2010 19:31 sara FLUENT 0 October 11, 2007 18:04 Knut Lehmann Main CFD Forum 2 June 29, 2007 04:53

All times are GMT -4. The time now is 20:09.