|
[Sponsors] |
Machnumber at boundary using Pressure Outlet and Target Mass Flow |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
May 8, 2018, 10:15 |
Machnumber at boundary using Pressure Outlet and Target Mass Flow
|
#1 |
Senior Member
Join Date: Nov 2015
Posts: 135
Rep Power: 10 |
Using a Pressure Outlet with a very low Pressure compared to the typical ambient pressure, the velocity at this outlet can become Mach1.
If the pressure is further lowered the exit acts as a nozzle and the exit blocks, which means that the software is no longer capable of lowering the pressure further and also mass flow does not increase anymore. This is all more or less known theory, but sometimes the velocity does indeed exceed Mach1 and ANSYS Fluent does not complain. But if a Target Mass Flow is specified and the Machnumber exceeds 98% then Fluent Does complain... Why? |
|
May 8, 2018, 10:43 |
|
#2 |
Senior Member
Lucky
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 5,676
Rep Power: 66 |
Well you already hit the nail on the head.
The target mass flow rate boundary condition is a pressure outlet condition with the pressure being adjusted each iteration to steer the mass flow towards the set point. If the exit is supersonic then adjusting the pressure does nothing. So you have told Fluent to adjust the pressure to reach the desired mass-flow, but it knows (and you also know) that adjusting the pressure does nothing. |
|
May 8, 2018, 11:18 |
|
#3 |
Senior Member
Join Date: Nov 2015
Posts: 135
Rep Power: 10 |
Yes, but the point is why does it complain when specifying a target mass flow, but not when the boundary is specified as a simple pressure outlet.
Shouldn't it always complain when the velocity exceeds mach1 at a boundary? |
|
May 8, 2018, 12:51 |
|
#4 |
Senior Member
Lucky
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 5,676
Rep Power: 66 |
The Mach number at a boundary (or any location for that matter) can exceed Mach 1. That is not a problem. With a fixed pressure and somehow the Mach number becomes 1 or greater, you get what you get (and you don't say anything about what the mass-flow needs to be). Here there is also not any problem. It is not a problem because all you have to do is extrapolate the pressure from the interior cells to the boundary and the pressure that you specify is not needed.
With a target mass flow, you say you want a certain mass flow, but there's no longer any knob Fluent can adjust to get you that mass flow. Here there is a problem because how the heck can I guarantee a certain mass flow if the boundary is sonic/supersonic? |
|
May 8, 2018, 14:45 |
|
#5 | |
Senior Member
Join Date: Nov 2015
Posts: 135
Rep Power: 10 |
Quote:
And what do you mean the pressure that I specify is not needed? How is a boundary pressure not needed, unless I use target mass flow? |
||
May 8, 2018, 16:02 |
|
#6 |
Senior Member
Lucky
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 5,676
Rep Power: 66 |
When the flow becomes supersonic, the nature of the flow changes from elliptic (in the subsonic case) to hyperbolic. When this happens it is no longer a boundary value problem but is now an initial value problem and you no longer need to provide the downstream BC's.
The targeted mass flow is a pressure outlet boundary condition. The difference is Fluent has a very dumb algorithm to change the pressure for you until you get the flow rate that you want. It is a convenience option and does not add any novel capability. You can manually adjust the outlet pressure yourself and achieve the same result (assuming it is even possible). Of course in the supersonic case, it is not possible and hence the warning. |
|
May 14, 2018, 06:39 |
|
#7 |
Senior Member
Join Date: Nov 2015
Posts: 135
Rep Power: 10 |
||
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Issues on the simulation of high-speed compressible flow within turbomachinery | dowlee | OpenFOAM Running, Solving & CFD | 11 | August 6, 2021 06:40 |
Wind turbine simulation | Saturn | CFX | 58 | July 3, 2020 01:13 |
Wrong flow in ratating domain problem | Sanyo | CFX | 17 | August 15, 2015 06:20 |
An error has occurred in cfx5solve: | volo87 | CFX | 5 | June 14, 2013 17:44 |
Low Mixing time Problem | Mavier | CFX | 5 | April 29, 2013 00:00 |