CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > ANSYS Meshing & Geometry

[ICEM] Pre Inlation in ICEM Error

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By siw

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   September 8, 2022, 16:07
Default Pre Inlation in ICEM Error
  #1
New Member
 
Join Date: Oct 2019
Posts: 4
Rep Power: 5
torreh is on a distinguished road
Hi,
i am trying to use the Pre Inflation (Fluent Meshing) method to generate a prism layer.
For this i first generate an all tri, patch dependent surface mesh.
When i go to start the Pre Inflation i get the following:

Running Fluent Meshing with Pre Inflation via the FieldMesher-Python-ExtensionModule...
Writing domain "___temp13688___.uns" ...
Done saving domain file.
Writing tetin file ___temp13688___.tin ...
Done saving tetin file.
"C:/PROGRA~1/ANSYSI~1/v182/icemcfd/WIN64_~1/../../commonfiles/CPython/2_7_13/winx64/Release/python/python.exe" "C:/PROGRA~1/ANSYSI~1/v182/icemcfd/WIN64_~1/../../commonfiles/CPython/2_7_13/winx64/Release/Ansys/ICEMCFD/FieldMesherController.py"
child process exited abnormally
ERROR: Import mesh failed
No prism mesh generated!


This happens everytime, even on the simplest geometries.

Does this happen to anyone else? How do i fix this?
I am using ICEM CFD 18.2 from the Ansys Workbench 18.2.


Thanks a lot!
torreh is offline   Reply With Quote

Old   September 9, 2022, 06:56
Default
  #2
Senior Member
 
Gert-Jan
Join Date: Oct 2012
Location: Europe
Posts: 1,632
Rep Power: 25
Gert-Jan will become famous soon enough
- Does this also happen if you run ICEM outside WB?
- Does ICEM work properly if you work the other way around? Meaning first volume and then inflation, i.e. Post inflation. (I never use pre inflation).
- I remember there was a bug in an old ICEM version in this particular menu. Not sure if it was 18.2. But I had to click the button post and pre inflation twice vice versa before it would do the pre inflation. If I didn't do these odd mouse clicks, it wouldn't work as expected. It had something to do with kind of intialisation of the software behind the screen. Please try, if you haven't done this before.
- Use a newer version. 18.2 is pretty old.
Gert-Jan is offline   Reply With Quote

Old   September 9, 2022, 12:12
Default
  #3
New Member
 
Join Date: Oct 2019
Posts: 4
Rep Power: 5
torreh is on a distinguished road
- Yes, it happens even outside of WB.
- Yes, post inflation works, but i am required to use pre inflation.
- I did not notice this GUI bug.

I think i found the problem. While i was working in ICEM, i was not able to open Fluent Meshing at the same time due to licensing issues. Now I run ICEM with the Mechanical Enterprise license, so that Fluent Meshing can use the CFD-PrepPost license.
Everything works fine now.
torreh is offline   Reply With Quote

Old   September 12, 2022, 07:14
Default
  #4
siw
Senior Member
 
Stuart
Join Date: Jul 2009
Location: Portsmouth, England
Posts: 697
Rep Power: 24
siw will become famous soon enough
In all my years of using ICEM CFD (which I am using less and less now as Ansys don't bother with it anymore) I never got pre-inflation to work well when making unstructured tetra-prism meshes. The only method I could get to work (and I think this is the Ansys recommended way based on their presentations) was using post-inflation as part of the following steps:

1) Conduct all geometry operations, use Build topology, put faces, edges into Parts, make Density Regions, assign element sizes etc. Save file with unique filename.
2) Generate an Octree volume mesh. Delete the volume elements (do not delete the surface elements). Check the surface mesh. Smooth the surface mesh. Save file with unique filename in case I want to restart at this stage.
3) Generate the volume mesh using the Delaunay method with TGlib and Use AF options activated (or maybe use the Advancing Front method). Check and volume mesh. Smooth the volume mesh. Save file with unique filename in case I want to restart at this stage.
4) Generate a few floating inflation layers. Split the inflation layers. Redistribute the layers. Or generate all the inflation layers in one go. This is all trial and error so that the first layer height and the volume transition from the last prism to first tetra are suitable. Smooth with inflation up to a very low quality value and smooth with inflation frozen up to higher quality values. Search for the two invaluable Ansys (from forum member PSYMN prism generation) inflation presentations in this forum.

This does not solve your pre-inflation errors but I've never had Ansys recommend using that.
Gert-Jan likes this.

Last edited by siw; September 12, 2022 at 09:58. Reason: Typo
siw is offline   Reply With Quote

Reply

Tags
ansys 18.2, error, icem, icem cfd 18.2, meshing 3d

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
DPM udf error haghshenasfard FLUENT 0 April 13, 2016 07:35
Compile problem ivanyao OpenFOAM Running, Solving & CFD 1 October 12, 2012 10:31
Ansys Fluent 13.0 UDF compilation problem in Window XP (32 bit) Yogini Fluent UDF and Scheme Programming 7 October 3, 2012 08:24
Version 15 on Mac OS X gschaider OpenFOAM Installation 113 December 2, 2009 11:23
Compiling problems with hello worldC fw407 OpenFOAM Installation 21 January 6, 2008 18:38


All times are GMT -4. The time now is 14:34.