CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > CFX

Problem in defining domain reference pressure

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   April 9, 2015, 07:47
Default Problem in defining domain reference pressure
  #1
New Member
 
Dhiren
Join Date: Apr 2015
Posts: 2
Rep Power: 0
dhiren012 is on a distinguished road
I'm new to CFX. I'm trying to analyse the fluid flow in an externally pressurised gas journal bearing using CFX. I've presuure inlets as well as pressure oulets. Feed holes as inlet(10 bar absolute), clearance spaces open to atmospehere as oulets(1.5 bar absolute). I'm facing problems in defining the boundary conditions. What will be the domain reference pressure in this case.
Please help I'm not getting the concept of the domain reference pressure.
dhiren012 is offline   Reply With Quote

Old   April 9, 2015, 09:23
Default
  #2
Senior Member
 
Join Date: Jun 2009
Posts: 1,815
Rep Power: 32
Opaque will become famous soon enough
You can set the domain reference pressure to 0 [Pa], and use absolute pressure on the boundaries.

If there are concerns about round off issues with pressure, you can use the double precision option.
Opaque is offline   Reply With Quote

Old   April 9, 2015, 17:35
Default
  #3
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,728
Rep Power: 143
ghorrocks is just really niceghorrocks is just really niceghorrocks is just really niceghorrocks is just really nice
While a zero reference pressure means you don't need to understand what is going on, it does mean you are liable to see numerical round off errors.

Reference pressure is simply a pressure which all other pressures are referenced to. For wind flow around a building, where the absolute pressure varies from 99999Pa to 100001Pa - if you do not use a reference pressure you are then asking the numerics to resolve tiny pressure differences between 99999Pa and 100001Pa. If you use a reference pressure of 100000Pa, then the model uses pressures of -1Pa to +1Pa. So now the pressure difference is resolved in the first significant digit as opposed to the 5th significant digit. The reference pressure simulation will be much more resistant to numerical round off.

So in your case use a reference pressure of 1.5 bar and an inlet pressure of 8.5 bar with an outlet of 0bar. Simple.
ghorrocks is offline   Reply With Quote

Old   April 13, 2015, 07:47
Default
  #4
New Member
 
Dhiren
Join Date: Apr 2015
Posts: 2
Rep Power: 0
dhiren012 is on a distinguished road
Thank u opaque and ghorrocks.. But i'm facing another problem which was unnoticed before.. I've only one domain as fluid.. but in cfx-pre, there are 2 different fluid fluid interferences. why ??? (Note-the geometry has been sliced)
Pls help
dhiren012 is offline   Reply With Quote

Old   April 13, 2015, 18:05
Default
  #5
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,728
Rep Power: 143
ghorrocks is just really niceghorrocks is just really niceghorrocks is just really niceghorrocks is just really nice
They sound like the automatically generated interfaces. If they are wrong then delete them.
ghorrocks is offline   Reply With Quote

Reply

Tags
cfx, domain reference pressure, gas bearing

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Second Derivative Zero - Boundary Condition fu-ki-pa OpenFOAM 11 March 27, 2021 04:28
Cfx aborted due to unknown errors AKHILESH S L CFX 2 October 10, 2013 17:16
Low Mixing time Problem Mavier CFX 5 April 29, 2013 00:00
air bubble is disappear increasing time using vof xujjun CFX 9 June 9, 2009 07:59
Does star cd takes reference pressure? monica Siemens 1 April 19, 2007 11:26


All times are GMT -4. The time now is 14:06.