|
[Sponsors] |
Cooling system design with CFX, Mechanics and system coupling |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
November 23, 2016, 14:11 |
Cooling system design with CFX, Mechanics and system coupling
|
#1 |
New Member
Giacomo Mingardo
Join Date: Jul 2016
Posts: 12
Rep Power: 10 |
Hi all,
I am trying to simulate a water cooling system to assess how much heat I can get rid of. This cooling system is a rather tight and long channel, inside an aluminium support. So, given the heat entering the aluminium support from one of the wall, I need to calculate the conduction in the support first, and the convection with the fluid after. For this simulations I used the System coupling between Steady Thermal Model and CFX, 7 as max iteratons and 0.05 as a residual target. I know that the low Reynolds (around 12000) number could have given problems with the turbulence model; I used the SST with no modifications, but I followed the suggestions on the boundary layer meshing given in: http://www.computationalfluiddynamic...oundary-layer/ My boundary conditions are: CFX: mass flow at inlet and outlet, temperature at the inlet Thermal: 1kW entering heat, 373 K of temperature at the support boundary The simulations keep giving unreasonable results, with extracted heat around 7 kW (despite the incoming heat is 1kW) and wall heat transfer coefficients of 125000 W/(m^2K) Do you have any idea? Let me know if you need any further information. Thank you in advance for your help |
|
November 23, 2016, 14:41 |
|
#2 |
Member
turbo4life
Join Date: Nov 2016
Posts: 41
Rep Power: 10 |
3 questions:
|
|
November 23, 2016, 15:15 |
|
#3 |
New Member
Giacomo Mingardo
Join Date: Jul 2016
Posts: 12
Rep Power: 10 |
Thank you for answering. So:
1)The residual plot is the one of CFX and the imbalance comes form the system coupling I suppose, right? in the residual one, there are a lot of other previous simulations before in which I was trying different turbulence approaches, but the simulation with the coupling is just the last part (I didn't know how to cut off the others) 2)I can try this, yes, how would it make it a difference? 3) Since it's water, I didn't even look at them and I relied on the Ansys material library. should I take a look? |
|
November 23, 2016, 15:37 |
|
#4 | |
Member
turbo4life
Join Date: Nov 2016
Posts: 41
Rep Power: 10 |
My answers in red below.
Quote:
|
||
November 23, 2016, 15:39 |
|
#5 |
Member
turbo4life
Join Date: Nov 2016
Posts: 41
Rep Power: 10 |
Can you send a picture of the model so I can see how you are applying the thermal BCs? If the items from the previous post are not the issue, then the thermal BCs could be.
|
|
November 29, 2016, 05:02 |
|
#6 |
New Member
Giacomo Mingardo
Join Date: Jul 2016
Posts: 12
Rep Power: 10 |
Hi, sorry but it took time to me to try your suggestions as I have not much computational power
I changed the flow constants on the material part of CFX. I took some values from the web, sites like http://www.engineeringtoolbox.com/. The simulation gives now a much better result: indeed the heat extracted is in the range that I expected. However, the wall heat transfer coefficient is still of an insane order of magnitude, like 10^5. Could I say that the simulation is reliable but that the coefficient has not been calculated correctly? So, can I trust this result, despite the value of the coefficient? BTW, pictures of the model are here below. The project overview shows lighting bolts with red crosses because my computer had a problem during the calculation and has been interrupted badly, but no problem with the model itself. The flow enters at 52 C and exits at 55 C. Other problem: the Heat Flux and the Wall Heat Flux integrals at the surface are not the same value. What is the difference? Is it normal? Thank you a lot, you have already been very kind and useful! Last edited by gmingardo; November 29, 2016 at 06:06. |
|
November 29, 2016, 12:43 |
|
#7 |
Member
turbo4life
Join Date: Nov 2016
Posts: 41
Rep Power: 10 |
How are you calculating the heat transfer coefficient? CFX estimates it by using a localized bulk temperature which can vary by a lot across the domain. There is an expert parameter that you can activate in CFX-Pre where you can specify a constant bulk temperature. This should fix the problem. Based on the picture of the model you provided, the heat transfer coefficient should be in the ballpark of a 1D calculation using the Dittus-Boelter relationship, or something similar.
|
|
November 29, 2016, 12:54 |
|
#8 |
Member
turbo4life
Join Date: Nov 2016
Posts: 41
Rep Power: 10 |
To activate this expert parameter, in your CFX-Pre model, select Insert>Solver>Expert Parameter. Next, select the "Physical Models" tab and under "Miscellaneous", activate the "tbulk for htc" parameter, and specify the bulk temperature for the heat transfer coefficient. This should resolve your issue.
|
|
November 29, 2016, 18:28 |
|
#9 |
Senior Member
Erik
Join Date: Feb 2011
Location: Earth (Land portion)
Posts: 1,188
Rep Power: 23 |
Why are you using system coupling for thermal only model? You can solve all of this directly in CFX.
|
|
November 29, 2016, 19:04 |
|
#10 |
New Member
Giacomo Mingardo
Join Date: Jul 2016
Posts: 12
Rep Power: 10 |
because I want to take into account the non uniformity of temperature and heat flux distribution on the wall. I think it makes the difference in the thin walls separing the channels
|
|
November 30, 2016, 13:47 |
|
#11 |
Senior Member
Erik
Join Date: Feb 2011
Location: Earth (Land portion)
Posts: 1,188
Rep Power: 23 |
Right, but you can do the solid heat transfer in CFX as well. It can do more than just fluids.
|
|
December 1, 2016, 05:44 |
|
#12 |
New Member
Giacomo Mingardo
Join Date: Jul 2016
Posts: 12
Rep Power: 10 |
oh, this I didn't know. So I should input another body, set it as solid and mesh it? and there I could do the analysis?
|
|
December 2, 2016, 15:26 |
|
#13 |
Senior Member
Erik
Join Date: Feb 2011
Location: Earth (Land portion)
Posts: 1,188
Rep Power: 23 |
Correct. Set interfaces between the domains as well.
|
|
Tags |
heat flux imbalance, low reynolds number, turbulence sst, wall heat transfer, water cooling |
Thread Tools | Search this Thread |
Display Modes | |
|
|