# CFX analysis of a sphere - drag too low

 Register Blogs Members List Search Today's Posts Mark Forums Read

 March 22, 2007, 19:47 CFX analysis of a sphere - drag too low #1 Rob Findlay Guest   Posts: n/a Sponsored Links Hi, Just starting out with CFX and I thought to learn I would model a sphere and compare drag with theory. One inch diameter sphere in 60 m/s airflow should have a Cd around 0.42 with total drag of around 0.46 N. My CFX results give a drag of 0.28 N (62% of theory). I was hoping people might be able to suggest a number of reasons I could be getting this low result. The output file for the run is located at: http://teambasic.files.wordpress.com...phere2_002.doc But I will precis what I have done below... I would greatly appreciate any help you can give me. Regards, Rob Loosly based on the "flow over a blunt body" tutorial. Default values unless stated. Steady State, Air Ideal Gas, Shear Stress Transport turb model (y+ at the ball is < 1, approx 15 nodes within the boundary layer thickness). Domain size: 3 x sphere diameter in front and to sides of sphere; 10 x sphere diameter behind. 2 x symmetry planes, 2 x free slip walls. sphere is no slip. inlet is subsonic, normal vel 60m/s, turb 5% medium. outlet is subsonic, static pressure, 0 atm. init conditions: y velocity 60m/s, turb eddy dissip selected. solver control: resudual RMS 1e-5, physical timescale 1/3 of time taken to flow through domain (did another run multiplied by 4, no real difference) mesh adaption based on abs pressure, eddy visc, velocity. 3 steps. total nodes 700,000. Solution Var * edge length. 50 iterations, RMS, 1e-4. The residuals looked okay, one order magnitude between RMS & max, no major change of drag values as i increased the mesh size. Do I need to be looking at transitional turbulence model?? Like I said, all help would be appreciated! Rob

 March 23, 2007, 06:25 Re: CFX analysis of a sphere - drag too low #2 Joe Guest   Posts: n/a Domain size: 3 x sphere diameter in front and to sides of sphere ... too small increase to 5. The nature of the vortex shedding may require transient analysis. Your steady state convergence is poor. The massive separation may also require DES, SAS-SST i.e. this is an ahmed body like problem. There may be turbulence transition effects, although your inlet velocities are high. Calculate the drag coefficient in the solver not in Post.

 March 23, 2007, 08:19 Re: CFX analysis of a sphere - drag too low #3 Dr Flow Squad Guest   Posts: n/a You have used a symmetry plane. So the force is for half a ball or what? | Pressure Force On Walls X-Comp. Y-Comp. Z-Comp. ball 2.4304E-01 6.6143E-02 2.4464E-01

 March 25, 2007, 18:45 Re: CFX analysis of a sphere - drag too low #4 Rob Findlay Guest   Posts: n/a Hi, Thanks for your response. I used two symmetry planes - therefore 1/4 of the ball. I multiplied the force by 4 and that is the value that is 60% of expected. Cheers, Rob

 March 25, 2007, 19:07 Re: CFX analysis of a sphere - drag too low #5 Rob Findlay Guest   Posts: n/a Joe, Thanks. I will try all of the above and post another response with my results. Regards, Rob

 March 26, 2007, 03:59 Re: CFX analysis of a sphere - drag too low #6 Fonzie Guest   Posts: n/a You might also wanna try to use a different advection scheme. In my last project with a blunt body the high-res-scheme did not yield very accurate results. SBF=1 worked much better - however there occured convergence issues from time to time.

 March 26, 2007, 10:11 Re: CFX analysis of a sphere - drag too low #7 Phil Guest   Posts: n/a which means you did not do a mesh refinement study?

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post famarcfd Main CFD Forum 0 December 14, 2010 08:53 famarcfd ANSYS 0 December 13, 2010 07:27 deus CFX 2 July 8, 2008 21:50 M. Essuri FLUENT 1 November 1, 2006 16:55 Himanshu FLUENT 1 December 25, 2005 09:51