
[Sponsors] 
Why are the flows on both sides of the interface inconsistent？ 

LinkBack  Thread Tools  Search this Thread  Display Modes 
November 14, 2022, 23:47 
Why are the flows on both sides of the interface inconsistent？

#1 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
When checking the CFX results, I found the interface between runner and draft tube shows different mass flow rate and other interfaces show the same.The error is around two percent.
This is stable simulation and only water involved. Why is that? 

November 15, 2022, 03:48 

#2 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,703
Rep Power: 143 
Is the simulation fully converged?
How are you calculating the mass flow rate on both sides of the interface? Does it match the mass flow rate calculations shown in the output file?
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. 

November 15, 2022, 04:05 

#3 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
It is fully converged.
Interface for computing mas flow rate: massFlow()@runner tube 1,massFlow()@runner tube 2.In one case, the mass fow rate for runner tube 1 is 101 kg/s equa to the inlet while the mass fow rate for runner tube 2 is 103 kg/s equal to the ouelet.The flow is also from the runner to draft tube. 

November 15, 2022, 04:11 

#4 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
For the inlet ,set mass flow rate.
For the outlet ,static pressure is given. 

November 15, 2022, 04:33 

#5 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,703
Rep Power: 143 
How tight is the imbalances?
Are you computing the massFlow()@XXX in the post processor or the solver? The post processor does not get the full integration point data, just the nodal data so is not as accurate as the solver. I presume there is no pitch change across the interface.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. 

November 15, 2022, 09:41 

#6 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
Thank you for your reply.
It's sure that the imbalance is below 1e3. For one model, I have many cases and all have the issue about inconsitent flow rate in the same nterface. I get the mass fow rate by using CFDPOST. How can get accurate result from the solver? You mean monitoring the mass flow rate when the solver is running? The pitch change is automatic. 

November 15, 2022, 09:44 

#7 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 


November 15, 2022, 14:43 

#8 
Senior Member
Join Date: Jun 2009
Posts: 1,804
Rep Power: 32 
What is the ratio between the flows on both sides of the interface? If you solution is reasonably converged, I guess is the same value as the pitch ratio or its inverse.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. 

November 15, 2022, 16:47 

#9 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,703
Rep Power: 143 
Note for convergence the residuals and imbalances are different things. For this issue you want to make sure the imbalance is small. So is your imbalances under 1E3 or the residual under 1E3? An imbalance under 1E3 is quite tight convergence but residuals under 1E3 is loose convergence and I would expect you to have an imbalance of a few percent if this is the case.
To calculate values in the solver you make a monitor point, set to the expression you want to evaluate. You can see the evaluated values in Solver Manager. Then the expression will be evaluated with the full accuracy of all integration points rather than just nodal values.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. 

November 15, 2022, 20:42 

#10 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
The ratio of mesh area is 1.02.And the the flow ratio is also 1.02.The pitch change is set at automatic.The interface are all 360degree rotating surfaces. Is I should set the pitch change to 360?


November 15, 2022, 20:51 

#11 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
Thank you.
Yeah, perhaps I should monitor some phsical variables in the solver although I know it is nneded. 

November 15, 2022, 21:41 

#12 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
Domain Interface Name : guide runner
Discretization type = GGI Intersection type = Partitioner Nonoverlap area fraction on side 1 = 0.00E+00 Nonoverlap area fraction on side 2 = 4.91E06 Pitch ratio ( area side 1 / area side 2 ) = 1.000 Pitch angle for side 1 [degrees] = 360.001 Pitch angle for side 2 [degrees] = 360.000 Domain Interface Name : runner tube Discretization type = GGI Intersection type = Partitioner Nonoverlap area fraction on side 1 = 3.03E03 Nonoverlap area fraction on side 2 = 2.08E01 Pitch ratio ( area side 1 / area side 2 ) = 0.978 Pitch angle for side 1 [degrees] = 360.000 Pitch angle for side 2 [degrees] = 360.000 

November 16, 2022, 07:52 

#13 
Senior Member
Join Date: Jun 2009
Posts: 1,804
Rep Power: 32 
The final, converged, flow ratio across the interface will always be pitch ratio (conservation of xxx).
If you are concerned the automatic pitch ratio is not exactly 1 (since it is 360 on both sides), you can manually set the pitch ratio using the specified angles option. Then, your pitch ratio should be exact, and the ratio of the flows will match that value
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. 

November 16, 2022, 07:56 

#14 
New Member
Join Date: Jan 2022
Posts: 16
Rep Power: 4 
yes. It's okay since I set the specified angle.


Tags 
inconsistent, mass flow, rsi 
Thread Tools  Search this Thread 
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Can I achieve better convergence?  sheaker  CFX  12  September 19, 2019 15:36 
Question about heat transfer coefficient setting for CFX  Anna Tian  CFX  1  June 16, 2013 06:28 
Smoothing interface of twophase flows  aiqch  Main CFD Forum  0  June 18, 2009 13:31 
Smoothing interface of twophase flows  aiqch  Main CFD Forum  0  June 18, 2009 13:26 
Replace periodic by inletoutlet pair  lego  CFX  3  November 5, 2002 20:09 