
[Sponsors] 
Diffrence between VOF alone and VOF coupled Level 7 ?? 

LinkBack  Thread Tools  Search this Thread  Display Modes 
June 18, 2013, 10:15 
Diffrence between VOF alone and VOF coupled Level 7 ??

#1 
New Member
Join Date: Jan 2013
Posts: 8
Rep Power: 13 
Hello everybody,
I have a problem.I have problem to found the differences between the VOF model alone and the VOF coupled Level7 model ? Fluent help don"t give lot of information on this model... Do you have an idea ? I try to simulate the flow of bubble in vertical pipe with diamter ranging from 1 to 10 mm.I succed for the diameter bigger than 5mm with VOF model but for the smaller diameters (D<5mm),the VOF model is not conclusive and i feal that the bubble gets stuck in the pipe... Someone has an explantion ? Thanks you very much for your time ! 

June 18, 2013, 11:10 

#2 
Senior Member
OJ
Join Date: Apr 2012
Location: United Kindom
Posts: 473
Rep Power: 20 
Coupledset algorithms try to capture the curvatures of the interface correctly, thus keeping the interface sharp. You can consider this coupled method for cases where surface tension plays important role.
OJ 

June 18, 2013, 11:15 

#3 
New Member
Join Date: Jan 2013
Posts: 8
Rep Power: 13 
Thank you for your reply !
I understand that VOF coupled to level 7 improved the interface definition. This is the only interest of level 7 ? 

June 18, 2013, 14:00 

#4 
Senior Member
OJ
Join Date: Apr 2012
Location: United Kindom
Posts: 473
Rep Power: 20 
First of all, it is levelset, not level 7. And do not underestimate the importance of interface definition. The whole VOF methodology is designed around it!
If you carefully observe, the benefits of VOF and levelset are complimentary to each other. While VOF is generally very good in ensuring the conservation of volume fractions through out the domains, including at interface, it struggles to exactly define the interface, because there exist very sharp gradients of volume fractions. At the same time levelset method approximates the interface quite correctly but the unevenness of the interface creates errors in mass/momentum calculations and hence the volume fraction conservation is often poor. But when you couple both of them, you couple the benifits. For instance, to define the interface at a cell level, VOF will accurately give the volumes of the cell occupied by both the phases, while, the levelset algorithms will accurately define the curvature and direction of the interface in the cell  thus providing details as to where exactly the interface intersects the cells. Thus, cell is divided into two phases with right volume fractions and with right shape of interface. This is particularly beneficial for high surface tensions because the velocity field nearby interface is significantly affected in presence of higher surface tension, influencing the interface. Now, how would you know if surface tension is important in your case? Take the following test: Calculate Capilary number if Re<<1: Calculate We number if Re>>1: where d is characteristic length of your bubble, say diameter and other symbols have usual meaning. Surface tension is important when We>>1 or Ca<<1 and this is an incentive to use levelset with VOF. OJ Last edited by oj.bulmer; June 18, 2013 at 17:46. Reason: Typo 

June 19, 2013, 04:54 

#5 
New Member
Join Date: Jan 2013
Posts: 8
Rep Power: 13 
Hello oj. Bulmer,
Thanks again for your reply and for the details on VOF and VOF coupled Level set model. I know it's level set and not level 7,this is a shorcut I have already calculate the Capillary and Weber numbers.The results are 0.01 and 0.00001 respectively so the surface tension should not influence the interface. Have you an idea why i feel that the bubble is stuck in the pipe ? I don't understand Maybe increase the size of the bubble ? Or add a low liquid flow ? I found some publications where they succeed to simulate that type of flow in very small pipes..I don't understand why it doesn't work 

June 28, 2013, 15:44 

#6 
Senior Member
Join Date: Jan 2011
Posts: 339
Rep Power: 16 
OJ i have a question? Is U indicates the velocity of gas or liquid?
Quote:


July 24, 2013, 04:49 

#7 
Senior Member
OJ
Join Date: Apr 2012
Location: United Kindom
Posts: 473
Rep Power: 20 
Mariam,
Sorry for a late reply, being away for a while from the forum U is the free stream velocity of water, or continuous phase. Cheers OJ 

July 26, 2013, 04:26 

#8 
New Member
Join Date: Jan 2013
Posts: 8
Rep Power: 13 
Ok thanks Oj.Bulmer !
Have a nice day 

August 7, 2013, 06:39 

#9 
New Member
mohamad
Join Date: Jun 2012
Posts: 12
Rep Power: 13 
Hello
I have a question. how Can I calculate phase velocity and phase position by level set+VOF ? Thank you so much 

August 8, 2013, 06:49 

#10 
Senior Member
OJ
Join Date: Apr 2012
Location: United Kindom
Posts: 473
Rep Power: 20 
Can you not use the CFDPost to grab the phase velocities? The phase positions can of course be understood by plotting the contour plots.
OJ 

August 19, 2013, 04:22 

#11 
New Member
Join Date: Jan 2013
Posts: 8
Rep Power: 13 
Hello mohamad3564 and oj.bulmer !
For the phase position,you can see that like said Oj.bulmer. For the phase velocity (in my case,velocity of gas bubble is liquid),you can't evaluate it just with CFDPost.You have to follow the position of the nose of the bubble at each time of the simulation. In my case,i follow the position of nose of the gas phase on the axis of the tube and i plot the position of the nose as a function of time simulation. The slope of this curve is the velocity of your gas phase. I hope this help you Have a good day 

Thread Tools  Search this Thread 
Display Modes  

