CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > FLUENT

changing velocity (outlet) BC to pressure outlet

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree4Likes
  • 1 Post By swiftaircraft
  • 2 Post By swiftaircraft
  • 1 Post By swiftaircraft

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   October 20, 2014, 03:59
Default changing velocity (outlet) BC to pressure outlet
  #1
Member
 
majid kamyab
Join Date: Jul 2014
Posts: 32
Rep Power: 8
majid_kamyab is on a distinguished road
the main purpose of this thread is how to change a velocity BC or the so called velocity inlet BC in fluent to pressure outlet. I did not have the pressure at outlet so I used velocity inlet (with negative sign in order to assign an outlet BC) in order to find the pressure.does this way work? cause there are some reverse flow on outlet although the same flux is passing through this BC



MORE DETAILS?



I will try to be very brief in explaining my problem if anyone needed further details feel free to ask.
in my case which is a distillation sieve tray
I have two inlet and two outlets.ALL OF THE liquid enters from one of the inlets and exits from one of the outlet
the same happens for the vapor phase.
I did not know the pressure at the outlets at first but the mass flow rate at the outlet is obvious.so velocity inlet
condition is used for the outlets.
I simulated hydrodynamics successfully and now I am tring to change BOTH of the outlets into pressure outlet BC.
when the pressure of velocity inlet BC is used reverse flow is reported by fluent at the vapor outlet.(and not the liquid outlet)
the reports showed that the same rate of vapor is exiting from Vapor outlet (although there are some reverse flow).
this reverse flow does not change as the iteration continues.
am I doing somthing wrong?
thanks in advance
majid_kamyab is offline   Reply With Quote

Old   October 20, 2014, 15:02
Default
  #2
Member
 
David Stanbridge
Join Date: Apr 2010
Location: Norwich, UK
Posts: 59
Rep Power: 13
swiftaircraft is on a distinguished road
Sometimes it is not realistic to have a pressure outlet. Have you specified the Operating Density in the Cell Zone Conditions panel to be the same as the gas phase? If not you may have a static pressure difference over the face of the outlet and consequently you may get reverse flow. Are the outlets perpendicular or parallel with the gravity vector. Also are you sing the full Eulerian model?
majid_kamyab likes this.
__________________
David Stanbridge

Swift TG Solutions Limited
www.swifttgsolutions.com
swiftaircraft is offline   Reply With Quote

Old   October 21, 2014, 04:02
Default
  #3
Member
 
majid kamyab
Join Date: Jul 2014
Posts: 32
Rep Power: 8
majid_kamyab is on a distinguished road
Quote:
Originally Posted by swiftaircraft View Post
Sometimes it is not realistic to have a pressure outlet. Have you specified the Operating Density in the Cell Zone Conditions panel to be the same as the gas phase? If not you may have a static pressure difference over the face of the outlet and consequently you may get reverse flow. Are the outlets perpendicular or parallel with the gravity vector. Also are you sing the full Eulerian model?
yes I have set the density in Cell zone condition to be the same as the gas phase
the outlet is parallel to the gravity vector and (g is on the opposite direction).
I dont understand what do you mean by FULL. but Im using eulerian model.



actually I realized somthing else too. when I set velocity BC I demand the BC to pass ONLY the vapor phase but there are a little liquid near the outlet. (volume fraction of liquid is about 10^-5) so the liquid velocity at this condition is on the opposite side of vapor and in to the system. (cause it cannot exit)
so when I change the BC to Pressure outlet there are some reverse flow for the liquid phase and not vapor.(I have checked it in report).
Ive let velocity BC to let a little liquid pass through this BC lets see what happens if I change to Pressure outlet afterward
majid_kamyab is offline   Reply With Quote

Old   October 21, 2014, 04:45
Default
  #4
Member
 
David Stanbridge
Join Date: Apr 2010
Location: Norwich, UK
Posts: 59
Rep Power: 13
swiftaircraft is on a distinguished road
Have you tried setting the gas outlet to pressure as this will remove the liquid without causing any continuity concerns. Keep the liquid outlet as a velocity inlet (with negative velocity as you have already done). This is the approach used for alot of multiphase separation equipment and works well.
__________________
David Stanbridge

Swift TG Solutions Limited
www.swifttgsolutions.com
swiftaircraft is offline   Reply With Quote

Old   October 22, 2014, 06:09
Default
  #5
Member
 
majid kamyab
Join Date: Jul 2014
Posts: 32
Rep Power: 8
majid_kamyab is on a distinguished road
Quote:
Originally Posted by swiftaircraft View Post
Have you tried setting the gas outlet to pressure as this will remove the liquid without causing any continuity concerns. Keep the liquid outlet as a velocity inlet (with negative velocity as you have already done). This is the approach used for alot of multiphase separation equipment and works well.
yes I agree with you.
but I think I should re init my case.
majid_kamyab is offline   Reply With Quote

Old   October 22, 2014, 06:19
Default
  #6
Member
 
David Stanbridge
Join Date: Apr 2010
Location: Norwich, UK
Posts: 59
Rep Power: 13
swiftaircraft is on a distinguished road
You should not need to reinitialise as long as you have some solution still. You may need to lower the URF's though for it to stabilise but then it should not be an issue.
__________________
David Stanbridge

Swift TG Solutions Limited
www.swifttgsolutions.com
swiftaircraft is offline   Reply With Quote

Old   October 22, 2014, 11:41
Default
  #7
Member
 
majid kamyab
Join Date: Jul 2014
Posts: 32
Rep Power: 8
majid_kamyab is on a distinguished road
Quote:
Originally Posted by swiftaircraft View Post
You should not need to reinitialise as long as you have some solution still. You may need to lower the URF's though for it to stabilise but then it should not be an issue.
as I said earlier there is no divergence about pressure outlet. but there are some reverse flow(does not disappear even after long time) I said that its because of velocity vectors of liquid that is on the opposite directions of vapor at vapor outlet as I was using velocity BC. URF is used in order to reduce the risk of divergence or to reach a better convergence (correct me if I'm wrong) so I don't think URF is going to help
thanks in advance
majid_kamyab is offline   Reply With Quote

Old   October 22, 2014, 11:50
Default
  #8
Member
 
David Stanbridge
Join Date: Apr 2010
Location: Norwich, UK
Posts: 59
Rep Power: 13
swiftaircraft is on a distinguished road
I only meant that you should reduce the URF's when you change any boundary from say velocity to pressure whilst keeping the same solution as the starting point. URF's can then be increased afterwards. Very often I find that without a URF reduction when making a BC type change you get divergence. Hope all goes well.
majid_kamyab likes this.
__________________
David Stanbridge

Swift TG Solutions Limited
www.swifttgsolutions.com
swiftaircraft is offline   Reply With Quote

Reply

Tags
change boundary condition, pressure outlet, reverse flow, velocity inlet

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Pressure Driven Supersonic Flow in Converging-Diverging Nozzle cdm OpenFOAM Running, Solving & CFD 7 August 28, 2019 01:37
simple model, difficult outlet Eric CFX 7 May 23, 2014 08:13
Pressure outlet boundary condition fluent_newbie FLUENT 0 December 1, 2011 23:51
ATTENTION! Reliability problems in CFX 5.7 Joseph CFX 14 April 20, 2010 15:45
Hydrostatic pressure in 2-phase flow modeling (long) DS & HB Main CFD Forum 0 January 8, 2000 15:00


All times are GMT -4. The time now is 12:56.