CFD Online Logo CFD Online URL
Home > Forums > FLUENT

can you tell me best gradient, pressure & momentum order selection in fluent

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree6Likes
  • 6 Post By LuckyTran

LinkBack Thread Tools Display Modes
Old   May 16, 2016, 02:00
Default can you tell me best gradient, pressure & momentum order selection in fluent
New Member
sanjeev kumar.m
Join Date: May 2016
Posts: 13
Rep Power: 2
sanjiiv is on a distinguished road
hi scholars,
can any one say which is used for appropriate solution of a problem,in fluent
in gradient ,
green gauss nodal method for what ?
green gauss cell method for what?
least square cell method for what?
then the order selection for pressure and momentum selection for
which order need to select for solution for different problem
whether first,second, third ,quick and power law..
sanjiiv is offline   Reply With Quote

Old   May 16, 2016, 10:16
Senior Member
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 1,569
Rep Power: 22
LuckyTran will become famous soon enough
It is highly problem dependent. But for a typical weakly compressible (incompressible or weakly compressible flows) the following is generally true: Note that the best method depends on whether you want highest accuracy or cheapest computation or some optimal in-between.

Least Squares & Green Gauss Node Based are the most accurate (least squares is slightly cheaper than Node based). Green Gauss Cell Based is least accurate but much cheaper than the other two.

The pressure interpolation scheme is applicable only to the pressure based solver. The density based solver does its own thing.

The linear pressure scheme is the absolute worst.

The second order pressure scheme, whenever it is available is generally the best. However, it is not accurate for flows with (strong) body forces and the PRESTO scheme is then the preferred scheme. The body force weighted scheme is great when the body forces are known a priori. The standard scheme uses a momentum-based weighting scheme to compute the pressure, but Second Order and Presto are generally much better unless there are stability issues.

For advective fluxes:
First order upwind is the least accurate in terms of order, but generally the most stable. The reason Fluent defaults to 1st order for some variables is because these equations are prone to numerical instabilities.

Second order upwind is much more accurate than 1st order, but has stability issues. Note however, that a 1st order scheme can have better absolute accuracy than a 2nd order scheme. The order of convergence for a 2nd order scheme is obtained via a loss of absolute accuracy (higher order of accuracy but errors are caused by numerical wiggles).

QUICK is 3rd order accurate for face values and 2nd order accurate for cell values on a hexahedral grid. For non-hexahedral cells, Fluent will use the second order scheme even if QUICK is selected (it will use QUICK for hexahedral cells and second order for non-hexahedral cells if both are present in the same mesh). In general the accuracy of QUICK is similar or slightly better than 2nd order upwind.

The power law scheme uses the exact power law solution to the advection-diffusion equation to interpolate values. It would be exact on an advection-diffusion problem, but Navier-Stokes is more complicated than simple advection-diffusion. The power law scheme has some niche utility; but in general, the power-law scheme is only slightly better than 1st order and not as accurate as second order and other schemes when all types of flow scenarios are considered.

The Third order MUSCL scheme can be interpreted as a generalization of the QUICK scheme for arbitrary grids (QUICK only works for hexahedral grids). The drawback is the gradient limiter doesn't work for MUSCL, and this scheme is prone to more pronounced overshoots and undershoots (these limiters do work for second order and QUICK). The scheme itself has the potential to better than 2nd order upwind and more usable than QUICK, but the implementation in Fluent needs a better limiter before you can use the MUSCL scheme for general cases.

QUICK and MUSCL schemes should really only be used by veterans. To use these schemes properly also requires a high quality grid, so some serious commitments are needed to get reasonable results with these two schemes. There's just very little gain for the cost in effort. They generally blow up in your face for a beginner. Beginners usually have all sorts of other issues to worry about though, like specifying the correct boundary and initial conditions. For beginners, I recommend to stick to defaults until they've learned how to use Fluent for many different types of problems before playing with these things. For beginners I would recommend 1st order on everything (because it's stable) or to use the defaults. Once they are familiar with how to setup a problem and solve it. The only setting I would recommend changing for beginners is switching from 1st to 2nd order upwind for all variables. Usually the simulation blows up at this point.
LuckyTran is offline   Reply With Quote

Old   May 18, 2016, 02:09
New Member
sanjeev kumar.m
Join Date: May 2016
Posts: 13
Rep Power: 2
sanjiiv is on a distinguished road
Thank you very much sir, for your detailed reply for my question....
sanjiiv is offline   Reply With Quote


Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
The fluent stopped and errors with "Emergency: received SIGHUP signal" yuyuxuan FLUENT 0 December 3, 2013 23:56
Rotating Reference Frame Pressure Gradient clac FLUENT 0 August 22, 2012 18:20
vortex cause pressure gradient or pressure gradient induce vortex? fruitkiwi Main CFD Forum 4 June 12, 2012 01:12
Pressure jump and momentum source Tanya FLUENT 1 June 4, 2009 15:22
pressure gradient term in low speed flow Atit Koonsrisuk Main CFD Forum 2 January 10, 2002 11:52

All times are GMT -4. The time now is 09:18.