CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > FLUENT

[FLUENT] How to calculate the drag in non-wall surface?

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   September 2, 2018, 07:52
Default [FLUENT] How to calculate the drag in non-wall surface?
  #1
New Member
 
Join Date: May 2018
Posts: 12
Rep Power: 4
bmaicuong is on a distinguished road
Hi everybody,

I am simulating the flow over and through a porous sphere, and would like calculate the drag on the porous surface (outer surface of the sphere).

However, Fluent allows to calculate the drag with wall-boundary condition only. Could you please recommend any way to calculate the drag on interior-surface? Or at least the way to determine the face area vectors of each elements on the porous surface só that I can use the momentum balance to get the drag?

I really need helps because I am quite new in FLUENT. Thank you all in advance.
bmaicuong is offline   Reply With Quote

Old   October 5, 2018, 08:51
Default
  #2
New Member
 
SAQIB JAMSHED
Join Date: Oct 2018
Posts: 1
Rep Power: 0
saqibjamshed is on a distinguished road
Have you solved your problem? If yes, please help me in this regard. I'm facing the same problem while working on a 2D porous geometry.
__________________
SAQIB JAMSHED
Research Scholar at Dept. of Chemical Engg.
IIT Roorkee, Roorkee, India
saqibjamshed is offline   Reply With Quote

Old   October 16, 2018, 11:41
Default
  #3
New Member
 
Join Date: May 2018
Posts: 12
Rep Power: 4
bmaicuong is on a distinguished road
Dear Jamshed,

I have found 2 ways to solve this problems. And unfortunately, they have different results of drag coefficient. You can check with your case.

1/ After completing the simulation, I change the boundary condition of porous surface (my case is in 3D) from interior to wall, so that I can force Fluent give me the drag coefficient. I am not sure this way is right but the positive thing is that we can have the face area vectors with wall boundary condition (so that we can approximate the momentum balance equation)

2/ I use the momentum balance over the porous object. Fluent provides information of velocity and pressure and we can get the face area vectors according to 1.

Hope that it can help you. Please let me know if it works for you. Thanks a lot
bmaicuong is offline   Reply With Quote

Old   April 4, 2020, 00:16
Smile
  #4
Member
 
Chi Zhang
Join Date: Aug 2017
Posts: 32
Rep Power: 5
C_Zhang is on a distinguished road
Hi bmaicuong
I am facing the same problem on calculating the force around a porous plate. Do you have more suggestions now?
Thank you very much for any of your reply.
C_Zhang is offline   Reply With Quote

Old   April 4, 2020, 00:26
Default
  #5
New Member
 
Join Date: May 2018
Posts: 12
Rep Power: 4
bmaicuong is on a distinguished road
Hi Zhang,

I used the momentum balance over the porous object to determine the force acting on it. You can see a more detailed strategy in my paper: https://doi.org/10.1016/j.oceaneng.2020.107140.

Check it and see if you can apply this for your case. Let me know if you need help.
bmaicuong is offline   Reply With Quote

Old   April 4, 2020, 00:30
Smile
  #6
Member
 
Chi Zhang
Join Date: Aug 2017
Posts: 32
Rep Power: 5
C_Zhang is on a distinguished road
I will read it carefully. You helped me a lot!
C_Zhang is offline   Reply With Quote

Old   April 5, 2020, 08:22
Default
  #7
Member
 
Chi Zhang
Join Date: Aug 2017
Posts: 32
Rep Power: 5
C_Zhang is on a distinguished road
Hi bmaicuong
I have to say, I failed. I tried to model Patursson's case, which you can find in https://doi.org/10.1016/j.oceaneng.2009.10.001. But I got totally wrong drag coefficients. I am wondering how you managed to utilise the method mentioned in your paper? Through a User Defined Function or anything else?
C_Zhang is offline   Reply With Quote

Old   April 5, 2020, 08:51
Default
  #8
New Member
 
Join Date: May 2018
Posts: 12
Rep Power: 4
bmaicuong is on a distinguished road
Dear Zhang,

I did not get the idea. Why do you know your results are wrong? Did you compare them with experimental data?

In our method, we calculate the drag force based on momentum balance; we just exported the data of pressure, velocity and face area vectors to handle Eqn (11). No need to use UDF.

Best,
Cuong Bui
bmaicuong is offline   Reply With Quote

Old   April 5, 2020, 09:07
Default
  #9
Member
 
Chi Zhang
Join Date: Aug 2017
Posts: 32
Rep Power: 5
C_Zhang is on a distinguished road
Hello Bui. So you mean you exported the result to some post processing software like CFD-Post? I think I can have a try. Thanks for your help.
C_Zhang is offline   Reply With Quote

Old   April 5, 2020, 09:13
Default
  #10
New Member
 
Join Date: May 2018
Posts: 12
Rep Power: 4
bmaicuong is on a distinguished road
Hi Zhang,

After finishing the simulations, you can export all data you need following this: File -> Export -> Solution data; Choose the File Type as ASCII then select the surfaces and quantities you need.

Let's give it a try and let me if it works. Good luck!

Best,
Cuong Bui
bmaicuong is offline   Reply With Quote

Old   April 5, 2020, 09:55
Default
  #11
Member
 
Chi Zhang
Join Date: Aug 2017
Posts: 32
Rep Power: 5
C_Zhang is on a distinguished road
Hi Bui, I am sorry to bother you again but, could you please tell me how you get the area vector? The boundary of porous media is set "interior" by default. The exported "X Face Area" and "Y Face Area" data is all zero on the porous media boundary.
C_Zhang is offline   Reply With Quote

Old   April 5, 2020, 09:59
Default
  #12
New Member
 
Join Date: May 2018
Posts: 12
Rep Power: 4
bmaicuong is on a distinguished road
Hi Zhang,

Change it to 'wall' (after finishing simulations and collecting other data of velocity and pressure) so that you can get the information of the face area.
bmaicuong is offline   Reply With Quote

Old   April 6, 2020, 10:18
Default
  #13
Member
 
Chi Zhang
Join Date: Aug 2017
Posts: 32
Rep Power: 5
C_Zhang is on a distinguished road
Hi Bui
I have to say, you really helped me a lot. I have got a satisfied result just now!
By the way, if anyone who could see this thread, I want to give you a tip that sometimes setting the correct porosity and clicking on "physical velocity" on the "cell zone conditions" task page will make your result different!
And, 2D simulation sometimes can not give you satisfied results.
Best
Chi Zhang
C_Zhang is offline   Reply With Quote

Reply

Tags
drag, porous media model, porous surface

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
[ICEM] Problems with coedge curves and surfaces tommymoose ANSYS Meshing & Geometry 6 December 1, 2020 12:12
[Gmsh] Error : Self intersecting surface mesh, computing intersections & Error : Impossible velan OpenFOAM Meshing & Mesh Conversion 3 October 22, 2015 12:05
Water subcooled boiling Attesz CFX 7 January 5, 2013 04:32
how to calculate forces on the wall with free surface? phsieh2005 Main CFD Forum 2 July 13, 2010 09:11
Calculate velocity inflow on a 2D surface in 3D quarkz Main CFD Forum 2 May 10, 2009 06:07


All times are GMT -4. The time now is 11:12.