CFD Online Logo CFD Online URL
Home > Forums > Software User Forums > ANSYS > FLUENT

How to study different stationary states

Register Blogs Members List Search Today's Posts Mark Forums Read

LinkBack Thread Tools Search this Thread Display Modes
Old   January 22, 2005, 13:31
Default How to study different stationary states
Posts: n/a
I have to study an object (in the form of a brick) situated in a wind tunnel and I'm interesting to see the differences at various inclinations. Each simulations is in a steady-state. At this moment, I'm creating manually with Gambit different inclinations one at time and then exporting mesh files in Fluent to run each inclinations one at time.

I was thinking to use an appropriate journal file to create the different geometries at the different inclinations to export mesh file: is it possible? Is it a good idea? How can I do to submit to Fluent all mesh files in a single step?

Otherwise, is it possible, to do so, using dynamic meshes or another method, without creating the different inclinations with Gambit?

IMPORTANT: Take into account that I need, for each inclinations, the study of a steady-state and not an unsteady-state!

thank you, Marta
  Reply With Quote

Old   January 24, 2005, 08:04
Default Re: How to study different stationary states
Posts: n/a
This depends on what you are trying to take into account... If you don't care about wall effects, then I would model the control volume as a hemisphere and change the flow vector in Fluent to give different inclination angles. This way, your force and moment monitors are always setup along the body-axes. If wall effects are important, and you don't want to completely remesh the model every time, you could use a non-conformal grid interface. Split the control volume with a sphere or cylinder that has the brick in its center and the center of the sphere (or centerline of the cylinder) should be coincident with the axis of rotation of your body. When you split the volumes make sure "connected" is turned off. Then you can mesh the two volumes separately, and define the coincident faces as interfaces. Then, for each inclination, you can rotate the volume containing the brick and export that mesh. As long as your mesh is reasonable, Fluent will create a smooth transition across the non-conformal interface and you won't even know it's there from the results. Just remember that you're rotating the body, and if you're trying to get any moments out of the results, they are about the cartesian coordinate systems (which is equivalent to a wind-axis system instead of a body-axis system).

Hope this helps, and goodluck Jason
  Reply With Quote

Old   January 24, 2005, 09:10
Default Re: How to study different stationary states
Posts: n/a
I would define a pressure far field and apply a different velocity vector for each analysis. Luca
  Reply With Quote

Old   January 24, 2005, 12:32
Default Re: How to study different stationary states
Posts: n/a
I agree, but that only works if you're not interested in wall effects from the tunnel wall. That's why I gave both options.

  Reply With Quote


Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
dpm study of solid-liquid study. bhanwar Main CFD Forum 0 September 29, 2011 08:21
Dynamic mesh in Fluent to study tire in contact with road surface lihuang FLUENT 10 March 8, 2011 10:21
How to output data from stationary part only? Aerolex FLUENT 0 November 16, 2009 22:46
Study Mario Main CFD Forum 0 August 24, 2009 09:59
droplet study rajiv kumar FLUENT 0 February 1, 2007 04:27

All times are GMT -4. The time now is 16:15.