# DPM converging Problem

 Register Blogs Members List Search Today's Posts Mark Forums Read

 May 29, 2007, 14:32 Re: DPM converging Problem #2 A A S Guest   Posts: n/a I have had problems myself. My residuals would fall to about an order of magnitude above the convergence criteria and stay there indefinately without changing. If your solution is stable, I suggest doing a mass and heat flux balance and checking grid independance. Those two are sufficient for a "converged solution."

 May 29, 2007, 16:20 Re: DPM converging Problem #3 Sujith Guest   Posts: n/a There will be convergence issues with DPM model as it creates source terms in the continuous phase. After 1 DPM iteration the momentum, energy etc of the particles are exchanged to the continuous phase as the respective source terms. This results in a sudden change in the solution equilibrium and there will be a residual jump. If the source terms are very high, you should increase the number of continuous phase iteration per dpm iteration so that the continuous phase converges after every DPM iteration. If there is still convergence trouble decrease the URF of DPM sources or try with a decreased DPM mass flow rate. Also remember that the DPM model is valid only under some conditions like very low volume loading... xq712000, 8cold8hot and ari003 like this.

 May 30, 2007, 02:06 Re: DPM converging Problem #4 Markus Alzon Guest   Posts: n/a Hello out there, I changed now my particles from droplets to inert particles (I did this before I read your advices). So by that, evaporation should be excluded (am I right?). And with this, my calculation is now running since yesterday. So, it seems that you both are right. About the grid: I have a very simple grid, and of course set the cell-volumes (compared with one droplet of maximum-size) not too low. However, what if in one cell not only one particle comes but, but many, so that they together occupy more than 10% of the cell-volume (or a parcel has too many droplets)? Would be this a break of the rule-of-thumb? I hope you understand my question. Thank you for your postings. It helped me to understand the DPM-Concept more. Greetings from Japan, MA

 May 30, 2007, 15:56 Re: DPM converging Problem #5 Sujith Guest   Posts: n/a Hi, In fluent DPM approach particles are considered as point masses which exchanges property with the continuous phase in the cell in which the particle is currently located. So the volume of particle does not pose a hindrance to the continuous phase flow. In the above case if the particles are clustered together in a single cell, the volume of particles are definitely going to affect the continuous phase flow and as Fluent neglects this fact, the results wont be as accurate as the actual physics... But in usual simulations this kind of situations are least expected and the DPM is used if conditions are met in a global sense. The clustering of particles is usually avoided by particle dispersion techniques like discrete random walk model or stochastic tracking etc.. Sujith

 June 5, 2007, 15:19 Re: DPM converging Problem #6 A A S Guest   Posts: n/a Thanks for the information Sujeth, even though I didn't pose the original question, what you provided is fairly practical for my simulations as well. Cheers AAS

 April 7, 2016, 12:41 No convergence even after 5000 iteration per Time step ? #7 New Member   Presteina Join Date: Feb 2016 Location: Canada Posts: 16 Rep Power: 10 Hello There, I am using DPM for spray of diesel liquid in combustion chamber with Non premixed approach. When spray starts injecting, my solution does not converges even at 5000 iteration per time steps. Can you please suggest me some tricks for the convergence ? What can be the possible mistakes that might have done by me ? Thank you in advance.