CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > OpenFOAM > OpenFOAM Programming & Development

Make wall-function read a newly defined field inside modified kEpsilon model

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By usv001

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   June 28, 2017, 23:29
Default Make wall-function read a newly defined field inside modified kEpsilon model
  #1
New Member
 
William Corrêa Radünz
Join Date: Jun 2016
Posts: 2
Rep Power: 0
Radunz is on a distinguished road
Greetings everyone,

I have been working on a modified kEpsilon model for wind flow modeling and it was necessary to redefine the once constant Cmu and as height-dependent field i.e. a volScalarField. I have also created it as an IObject to plot it along with the remaining fields and all works fine. The problems begin now. It just so happens that epsilonWallFunction and nutkRoughWallFunction depend on Cmu and as such the must access the modified kEpsilon height-dependent Cmu, which I will name after Cmu(z). I am well aware that the wall functions are general and thus have no information about the selected turbulence model so they access turbulence fields through their base class turbulenceModel.H through this lines, as example (turbulence kinectic energy, viscosity and turbulent viscosity fields):

@epsilonWallFunction

const tmp<volScalarField> tk = turbulence.k();
const volScalarField& k = tk();

const tmp<scalarField> tnuw = turbulence.nu(patchi);
const scalarField& nuw = tnuw();

const tmp<scalarField> tnutw = turbulence.nut(patchi);
const scalarField& nutw = tnutw();

However, when I try to access the newly created Cmu(z) through this

const tmp<volScalarField> tCmuw = turbulence.CmuZ();


The compiler complains saying basically that "error: ‘const class Foam::turbulenceModel’ has no member named ‘CmuZ’". This is attached as "log.withoutTurbulenceModel". So what have I done? I realized the call above led to the base class turbulenceModel so I declared CmuZ as a virtual function there.

@turbulenceModel.H

virtual tmp<volScalarField> CmuZ() const = 0;

When I compile, I get more issues. In my view, the issue is that somehow turbulenceModel's derived classes (turbulence models) are scanned after the CmuZ() field which is only implemented in kEpsilon model through run-time selection tables. There are some lines as

"error: cannot allocate an object of abstract type ‘Foam::incompressible::RASModels::qZeta’
return autoPtr<baseType>(new baseType##Type parList); \
^
../turbulenceModels/lnInclude/RASModel.H:111:9: note: in expansion of macro ‘declareRunTimeSelectionTable’"

and that's when I get lost. I've been trying so solve this for two weeks, read about polymorphism and so on but stagnated.

Best regards.
Attached Files
File Type: txt log.withoutTurbulenceModel.txt (5.6 KB, 1 views)
Radunz is offline   Reply With Quote

Old   July 1, 2017, 00:54
Default
  #2
Member
 
Join Date: Sep 2015
Location: Singapore
Posts: 93
Rep Power: 6
usv001 is on a distinguished road
Hi there,

You are correct that the "cannot allocate an object of abstract type" error occurs because you are trying to a create an object which has a pure virtual function, i.e. one which ends with '= 0'. I think that means that each of the derived class is required to provide an implementation of the CmuZ() which is not what you want to do.

Try writing the function body of the CmuZ() function in turbulenceModel.H to return a tmp<volScalarField> with the some dummy Cmu value like 0.09.

Code:
tmp<volScalarField> CmuZ()
{
    return 
    (
        new volScalarField
        (
            volScalarField
            (
                IOobject("Cmu", ...), 
                mesh, 
                dimensionedScalar("dummy", dimless, 0.09)
            )
        )
    );
}
Then, you may specialize this function in your own custom turbulence model. Now, you should be able to access this function from the wall function classes. I am not sure if this will work for certain but please give it a try and let everyone know of the result.

An even more straightforward way could be to access the Cmu volScalarField by looking up the object from its object registry, e.g.

Code:
const volScalarField& Cmu = mesh.lookupObject<volScalarField>("Cmu");
Cheers,
USV
Radunz likes this.
usv001 is offline   Reply With Quote

Old   July 18, 2017, 22:39
Default
  #3
New Member
 
William Corrêa Radünz
Join Date: Jun 2016
Posts: 2
Rep Power: 0
Radunz is on a distinguished road
Quote:
Originally Posted by usv001 View Post
Hi there,

You are correct that the "cannot allocate an object of abstract type" error occurs because you are trying to a create an object which has a pure virtual function, i.e. one which ends with '= 0'. I think that means that each of the derived class is required to provide an implementation of the CmuZ() which is not what you want to do.

Try writing the function body of the CmuZ() function in turbulenceModel.H to return a tmp<volScalarField> with the some dummy Cmu value like 0.09.

Code:
tmp<volScalarField> CmuZ()
{
    return 
    (
        new volScalarField
        (
            volScalarField
            (
                IOobject("Cmu", ...), 
                mesh, 
                dimensionedScalar("dummy", dimless, 0.09)
            )
        )
    );
}
Then, you may specialize this function in your own custom turbulence model. Now, you should be able to access this function from the wall function classes. I am not sure if this will work for certain but please give it a try and let everyone know of the result.

An even more straightforward way could be to access the Cmu volScalarField by looking up the object from its object registry, e.g.

Code:
const volScalarField& Cmu = mesh.lookupObject<volScalarField>("Cmu");
Cheers,
USV
Thank you very much. The piece of code
Code:
const volScalarField& Cmu = mesh.lookupObject<volScalarField>("Cmu");
indeed solved my problems.
Radunz is offline   Reply With Quote

Reply

Tags
runtimeselection, turbulence, wallfunction

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Wrong flow in ratating domain problem Sanyo CFX 17 August 15, 2015 06:20
[blockMesh] non-orthogonal faces and incorrect orientation? nennbs OpenFOAM Meshing & Mesh Conversion 7 April 17, 2013 05:42
Water subcooled boiling Attesz CFX 7 January 5, 2013 03:32
[blockMesh] error message with modeling a cube with a hold at the center hsingtzu OpenFOAM Meshing & Mesh Conversion 2 March 14, 2012 09:56
meshing F1 front wing Steve FLUENT 0 April 17, 2003 12:37


All times are GMT -4. The time now is 07:42.