CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > OpenFOAM > OpenFOAM Running, Solving & CFD

Supercavitation / overPimpleDyMFoam

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   August 9, 2021, 01:21
Default Supercavitation / overPimpleDyMFoam
  #1
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
Dear Foamers,

A cylinder fast moving in water with 500 m/s. We would like to see the cavity around cylinder.

1. Can we solve this problem with overPimpleDyMFoam?

2. Do we need to use Volume Of Fluid (VOF) Technic?

3. Can we use alpha.water with overPimpleDyMFoam?

Any answer will be appreciated. Thanks & regards.
canik01@yahoo.com is offline   Reply With Quote

Old   August 12, 2021, 18:40
Default overPimpleDyMFoam + VoF
  #2
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
Can we use Volume of Fluid (VoF) Technique with overPimpleDyMFoam solver?
canik01@yahoo.com is offline   Reply With Quote

Old   August 13, 2021, 03:21
Default
  #3
Senior Member
 
Yann
Join Date: Apr 2012
Location: France
Posts: 520
Rep Power: 19
Yann will become famous soon enough
No you can't, you need to use overInterDyMFoam, which is the overset version of interFoam (VOF)


I'm not sure it can handle cavitation though. There is a specific solver for this: cavitatingFoam. But it doesn't have an overset version.



Yann
Yann is offline   Reply With Quote

Old   August 14, 2021, 00:51
Default
  #4
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
Thank you very much Yann.

Can we use 6DOF with overInterDyMFoam?

Can we use PISO with overInterDyMFoam?
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 03:36
Default
  #5
Senior Member
 
Yann
Join Date: Apr 2012
Location: France
Posts: 520
Rep Power: 19
Yann will become famous soon enough
Hi Senel,

Yes you can use both.
Have a look at the floatinBody tutorial to have an example of 6DoF with overInterDyMFoam.

Regards,
Yann
Yann is offline   Reply With Quote

Old   August 16, 2021, 05:22
Default
  #6
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
Hi Yann,

Thank you for your reply.

I tried floating object that you have pointed and get the following error. I have seen this error several times when I try to work with floatingobject in local tutorial folder:

// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
Create time

Create mesh for time = 0

Using #codeStream at line 44 in file "D:/___OpenFOAM/openfoam-master-tutorials-multiphase-overInterDyMFoam-floatingBody/tutorials/multiphase/overInterDyMFoam/floatingBody/background/constant/dynamicMeshDict.sixDoFRigidBodyMotionCoeffs"


--> FOAM FATAL IO ERROR: (openfoam-2012)
This code should not be executed by someone with administrator rights for security reasons.
It generates a shared library which is loaded using dlopen



file: D:/___OpenFOAM/openfoam-master-tutorials-multiphase-overInterDyMFoam-floatingBody/tutorials/multiphase/overInterDyMFoam/floatingBody/background/constant/dynamicMeshDict.sixDoFRigidBodyMotionCoeffs at line 26.

From static void Foam::dynamicCode::checkSecurity(const char*, const Foam::dictionary&)
in file db/dynamicLibrary/dynamicCode/dynamicCode.C at line 71.

FOAM exiting


Do you know how can I solve this?

Regards,

Senel
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 05:26
Default
  #7
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
I use Windows.
There is other floatingobject case without 6DOF. I dont face the error above for that one without 6DOF. Only the case including 6DOF gives this error.
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 06:06
Default
  #8
Senior Member
 
Yann
Join Date: Apr 2012
Location: France
Posts: 520
Rep Power: 19
Yann will become famous soon enough
The error is due to the #codeStream function defined in background/constant/dynamicMeshDict.

This function is used to compute the moment of inertia of the object according to the dimensions Lx, Ly, Lz and mass defined beforehand.

You get this error because codeStream dynamically compile some code to compute these values and you are not allowed to compile code with the Windows version.

I guess you are using the cross-compiled windows binaries (mingw) ?

However, you don't have to use the dynamic code function. You can remove it and compute the moment of inertia yourself in order to run the tutorial with your current setup.

Cheers,
Yann
Yann is offline   Reply With Quote

Old   August 16, 2021, 07:51
Default
  #9
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
I guess I use mingw: OpenFOAM-MS-DOSPrompt.bat

I deleted the block:
/*
momentOfInertia #codeStream
{
...
...
}
*/

but same error occurred.

I deleted dynamicMeshDict file and run overInterDyMFoam solver again, the result was same.

I tried interFoam solver to run, same error

This code should not be executed by someone with administrator rights for security reasons.
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 08:42
Default
  #10
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
with the interFoam solver run, the error is different :
Unknown asymetric matrix solver type PCG.
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 09:04
Default
  #11
Senior Member
 
Yann
Join Date: Apr 2012
Location: France
Posts: 520
Rep Power: 19
Yann will become famous soon enough
You get this error because there is dynamic code elsewhere in the case.

In the background/system/controlDict, you have to delete the coded function object alphaVol.

By the way, you can't delete the momentOfInertia block in dynamicMeshDict because the sixDoF model needs the moment of inertia of the object to compute its displacement. You have to define it using this syntax:
Code:
momentOfInertia (Ix Iy Iz);
Yann is offline   Reply With Quote

Old   August 16, 2021, 11:29
Default
  #12
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
Yes, I put momentOfInertia(Ix Iy Iz);

I did what you suggested. It worked for 4-5 minutes but failed somehow. I attached the console messages. I would appriciate if you can suggest me to correct this.

Other question, there are very big numbers of angular velocity inside the messages. How did I get this? I have checked the input files and could not see any velocity (linear or angular) values.
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 12:20
Default
  #13
Senior Member
 
Yann
Join Date: Apr 2012
Location: France
Posts: 520
Rep Power: 19
Yann will become famous soon enough
Quote:
Originally Posted by canik01@yahoo.com View Post

Other question, there are very big numbers of angular velocity inside the messages. How did I get this? I have checked the input files and could not see any velocity (linear or angular) values.
You don't specify these velocities, the sixDoF model compute it from the forces on the object.

So maybe the wrong moment of inertia? What values did you use?
Have you modified other parameters?

It seems you did not post the log files so I cannot really help more than this for now.

Yann
Yann is offline   Reply With Quote

Old   August 16, 2021, 13:22
Default
  #14
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
I used:
momentOfInertia(4.45E-16 4.45E-16 2.25E-16);

It seems attachment is lost. Let me paste in 3 parts.
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 13:24
Default
  #15
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
D:\___OpenFOAM\AAB\background>overInterDyMFoam
/*---------------------------------------------------------------------------*\
| ========= | |
| \\ / F ield | OpenFOAM: The Open Source CFD Toolbox |
| \\ / O peration | Version: v2012 |
| \\ / A nd | Website: www.openfoam.com |
| \\/ M anipulation | |
\*---------------------------------------------------------------------------*/
Build : 79e353b84e-20201222 OPENFOAM=2012
Arch : "LSB;label=32;scalar=64"
Exec : overInterDyMFoam
Date : Aug 16 2021
Time : 18:03:07
Host : DESKTOP-K454CLA
PID : 15108
I/O : uncollated
Case : D:/___OpenFOAM/AAB/background
nProcs : 1
trapFpe: Floating point exception trapping enabled (FOAM_SIGFPE).
fileModificationChecking : Monitoring run-time modified files using timeStampMaster (fileModificationSkew 5, maxFileModificationPolls 20)
allowSystemOperations : Allowing user-supplied system call operations

// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
Create time

Create mesh for time = 0

Selecting dynamicFvMesh dynamicOversetFvMesh
Selecting motion solver: sixDoFRigidBodyMotion
Applying solid body motion to entire mesh
Selecting sixDoFSolver Newmark
Translational constraint tensor (0 0 0 0 0 0 0 0 1)
Rotational constraint tensor (1 0 0 0 1 0 0 0 1)

PIMPLE: no residual control data found. Calculations will employ 2 corrector loops

Reading field p_rgh

Reading field U

Reading/calculating face flux field phi

Creating cellMask field to block out hole cells

Creating interpolatedCells field

Reading transportProperties

Selecting incompressible transport model Newtonian
Selecting incompressible transport model Newtonian
Selecting turbulence model type RAS
Selecting RAS turbulence model kEpsilon
RAS
{
RASModel kEpsilon;
turbulence on;
printCoeffs on;
Cmu 0.09;
C1 1.44;
C2 1.92;
C3 0;
sigmak 1;
sigmaEps 1.3;
}


Reading g

Reading hRef
Calculating field g.h

No MRF models present

No finite volume options present
DICPCG: Solving for pcorr, Initial residual = 0, Final residual = 0, No Iterations 0
Reading/calculating face velocity Uf

Courant Number mean: 0 max: 0

Starting time loop

Courant Number mean: 0 max: 0
Interface Courant Number mean: 0 max: 0
deltaT = 0.00119904076739
Time = 0.00119904

PIMPLE: iteration 1
forces forces:
rho: rho
Not including porosity effects

6-DoF rigid body motion
Centre of rotation: (0.5 0.5 0.299996831223)
Centre of mass: (0.5 0.5 0.299996831223)
Orientation: (1 -1.63669391233e-09 -2.95550669418e-09 1.63669394173e-09 1 9.95020585532e-09 2.9555066779e-09 -9.95020586016e-09 1)
Linear velocity: (-0 -0 -0.00528551978417)
Angular velocity: (-1.65969433687e-05 -4.92978515903e-06 2.73000547029e-06)
cellVolumeWeight : detected 1 mesh regions

zone:0 nCells:513344
Marking patch-cells on zone 0

After patch analysis : nCells : 513344
other : 466972
patch : 36464
overset: 9908

cellVolumeWeight : detected 3 mesh regions after overset

Front : fraction:1 size:19824
Overset analysis : nCells : 513344
calculated : 494480
interpolated : 8956
hole : 9908

Execution time for mesh.update() = 5.936 s
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
DILUPBiCGStab: Solving for p_rgh, Initial residual = 1, Final residual = 0.00760596752673, No Iterations 16
time step continuity errors : sum local = 1.06238437225e-09, global = 1.03013829106e-09, cumulative = 1.03013829106e-09
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.0524625804512, Final residual = 8.78548417131e-10, No Iterations 40
time step continuity errors : sum local = 7.91020323273e-16, global = 1.28535149463e-17, cumulative = 1.03013830391e-09
smoothSolver: Solving for epsilon, Initial residual = 0.00743570667599, Final residual = 9.00841209398e-10, No Iterations 3
smoothSolver: Solving for k, Initial residual = 0.999999999863, Final residual = 7.66652009867e-09, No Iterations 4
PIMPLE: iteration 2
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.0232907830062, Final residual = 0.000205887888379, No Iterations 6
time step continuity errors : sum local = 1.68756915319e-10, global = -1.45081102075e-10, cumulative = 8.85057201837e-10
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.000781904793653, Final residual = 8.93768281698e-10, No Iterations 30
time step continuity errors : sum local = 7.28211539113e-16, global = -1.09868682489e-16, cumulative = 8.85057091968e-10
smoothSolver: Solving for epsilon, Initial residual = 0.00446626862604, Final residual = 2.42417052886e-10, No Iterations 3
smoothSolver: Solving for k, Initial residual = 0.012986580111, Final residual = 2.5960091425e-09, No Iterations 3
ExecutionTime = 33.981 s ClockTime = 34 s

Courant Number mean: 1.55487331975e-05 max: 0.000455624445287
Interface Courant Number mean: 0 max: 0
deltaT = 0.0014374667413
Time = 0.00263651

PIMPLE: iteration 1
forces forces:
rho: rho
Not including porosity effects

6-DoF rigid body motion
Centre of rotation: (0.5 0.5 0.299980125162)
Centre of mass: (0.5 0.5 0.299980125162)
Orientation: (0.776270683644 -0.526128983104 0.347263759775 -0.33437062227 0.123350716039 0.9343344625 -0.534415674057 -0.841411251405 -0.0801685308076)
Linear velocity: (0 0 -0.0179582331751)
Angular velocity: (939184.683697 -563475.839125 -1222759.66172)
cellVolumeWeight : detected 1 mesh regions

zone:0 nCells:513344
Marking patch-cells on zone 0

After patch analysis : nCells : 513344
other : 466972
patch : 36464
overset: 9908

cellVolumeWeight : detected 3 mesh regions after overset

Front : fraction:1 size:19824
Overset analysis : nCells : 513344
calculated : 494480
interpolated : 8956
hole : 9908

Execution time for mesh.update() = 6.103 s
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.99995375697, Final residual = 0.00845346027011, No Iterations 13
time step continuity errors : sum local = 0.000125286431428, global = 3.75043913352e-05, cumulative = 3.75052763923e-05
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.380097852649, Final residual = 9.57548068101e-10, No Iterations 44
time step continuity errors : sum local = 4.68802909906e-11, global = -3.51268570072e-12, cumulative = 3.75052728796e-05
smoothSolver: Solving for epsilon, Initial residual = 0.695972178136, Final residual = 6.63798287942e-09, No Iterations 25
smoothSolver: Solving for k, Initial residual = 0.999651749679, Final residual = 7.61925327133e-09, No Iterations 25
PIMPLE: iteration 2
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.266825331208, Final residual = 0.00249242465244, No Iterations 8
time step continuity errors : sum local = 8.09936168876e-05, global = 2.49451130953e-05, cumulative = 6.24503859749e-05
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.0843161322737, Final residual = 7.27528717452e-10, No Iterations 37
time step continuity errors : sum local = 3.64109208287e-11, global = 4.89648251891e-12, cumulative = 6.24503908714e-05
smoothSolver: Solving for epsilon, Initial residual = 0.102619751728, Final residual = 7.78687600509e-09, No Iterations 48
smoothSolver: Solving for k, Initial residual = 0.970662778002, Final residual = 9.82883850463e-09, No Iterations 565
ExecutionTime = 70.221 s ClockTime = 71 s

Courant Number mean: 2.00725072574 max: 63.2786470141
Interface Courant Number mean: 0 max: 0
deltaT = 3.40753283428e-05
Time = 0.00267058

PIMPLE: iteration 1
forces forces:
rho: rho
Not including porosity effects

6-DoF rigid body motion
Centre of rotation: (0.5 0.5 0.299979528033)
Centre of mass: (0.5 0.5 0.299979528033)
Orientation: (0.387102407007 0.888790223757 -0.245364350799 0.750311018546 -0.148981319873 0.64407914248 0.53589654033 -0.433424162319 -0.724540125583)
Linear velocity: (0 0 -0.0170893800223)
Angular velocity: (-489835497119 1.43832612225e+13 1.17263307329e+13)
cellVolumeWeight : detected 1 mesh regions

zone:0 nCells:513344
Marking patch-cells on zone 0

After patch analysis : nCells : 513344
other : 466972
patch : 36464
overset: 9908

cellVolumeWeight : detected 3 mesh regions after overset

Front : fraction:1 size:19824
Overset analysis : nCells : 513344
calculated : 494480
interpolated : 8956
hole : 99087
canik01@yahoo.com is offline   Reply With Quote

Old   August 16, 2021, 13:26
Default
  #16
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
PIMPLE: iteration 1
forces forces:
rho: rho
Not including porosity effects

6-DoF rigid body motion
Centre of rotation: (0.5 0.5 0.30232338962)
Centre of mass: (0.5 0.5 0.30232338962)
Orientation: (0.876768506551 -0.369453376802 -0.307865536054 0.118119048666 0.785996218752 -0.606842512065 0.466181162492 0.495695618779 0.732776212264)
Linear velocity: (0 0 2.58474731002e+41)
Angular velocity: (-8.40530353751e+56 3.0199876719e+57 -3.54845284751e+57)
cellVolumeWeight : detected 1 mesh regions

zone:0 nCells:513344
Marking patch-cells on zone 0

After patch analysis : nCells : 513344
other : 466972
patch : 36464
overset: 9908

cellVolumeWeight : detected 3 mesh regions after overset

Front : fraction:1 size:19824
Overset analysis : nCells : 513344
calculated : 494480
interpolated : 8956
hole : 9908

Execution time for mesh.update() = 6.128 s
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
smoothSolver: Solving for alpha.water, Initial residual = 0, Final residual = 0, No Iterations 0
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
MULES: Correcting alpha.water
MULES: Correcting alpha.water
MULES: Correcting alpha.water
Phase-1 volume fraction = 0 Min(alpha.water) = 0 Max(alpha.water) = 0
DILUPBiCGStab: Solving for p_rgh, Initial residual = 0.000758763959602, Final residual = 5.95872807485e-06, No Iterations 4
time step continuity errors : sum local = 9.48505988825e-08, global = 5.95306438863e-08, cumulative = -2.00122928483e+20
DILUPBiCGStab: Solving for p_rgh, Initial residual = 6.32441617964e-58, Final residual = 6.32441617964e-58, No Iterations 0
time step continuity errors : sum local = 1.66080050762e+29, global = -8.6938078679e+14, cumulative = -2.00123797864e+20
smoothSolver: Solving for epsilon, Initial residual = 1, Final residual = 0.999999998127, No Iterations 1000
smoothSolver: Solving for k, Initial residual = 1, Final residual = 0.923117714442, No Iterations 1000

D:\___OpenFOAM\AAB\background>
canik01@yahoo.com is offline   Reply With Quote

Old   August 17, 2021, 05:01
Default
  #17
Senior Member
 
Yann
Join Date: Apr 2012
Location: France
Posts: 520
Rep Power: 19
Yann will become famous soon enough
Hi,

how did you compute your moment of inertia? The values you used seem quite low.

I end up with these values:
Code:
momentOfInertia (0.2924544 0.2924544 0.1548288);
I didn't run the full case but it seems to run fine.

Cheers,
Yann
Yann is offline   Reply With Quote

Old   August 17, 2021, 10:16
Default
  #18
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
I've taken the dimensions of the floatingobject from paraview as 0.24 mm x 0.24 mm x 0.4 mm and draw a solid in CATIA. Now I remember I forget to change the density I think the default density is 1000 kg/m3 which is the same with water. Maybe thats the reason I end up with a very small moment values.
canik01@yahoo.com is offline   Reply With Quote

Old   August 17, 2021, 10:36
Default
  #19
Senior Member
 
Yann
Join Date: Apr 2012
Location: France
Posts: 520
Rep Power: 19
Yann will become famous soon enough
OK I get it now. The dimensions of the object are in meters and not millimeters: 0.24m x0.24m x 0.4m.
This is why you get very small inertia values, in addition to the wrong density.


By the way, both dimensions and density of the object are specified in the dynamicMeshDict.


It should run fine with the correct values.

Yann
Yann is offline   Reply With Quote

Old   August 17, 2021, 17:15
Default
  #20
New Member
 
Senel Canik
Join Date: Aug 2021
Posts: 22
Rep Power: 3
canik01@yahoo.com is on a distinguished road
Dear Yann,

It worked fine. Thank you very much for your time and effort. You are very helpful.
Using 0.24m x 0.24m x 0.4m and 700 kg/m3, I found same moment of inertia.

Floatingobject is very nice application of:
-Dynamic mesh
-Overset mesh
-6DOF
-Volume of Fluid (VoF) in this case water and water vapor
-PISO

My application is a cylinder inside water. The initial velocity is 500 m/s.

I recently experienced overInterDyMFoam and interPhaseChangeDyMFoam. But I am not sure wich solver is more suitable for my cylinder application.

Any suggestion is welcome.

Thx & Regards,

Senel
canik01@yahoo.com is offline   Reply With Quote

Reply

Tags
cavitation, overpimpledymfoam, supercavitation, vof

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Can I use OverPimpleDyMFoam and 6DOF rigid body motion at the same time? SihunLee OpenFOAM Running, Solving & CFD 1 July 2, 2019 04:01
what are the best solvers for P, U, cellDisplacement for overPimpleDyMFoam kimou OpenFOAM Pre-Processing 2 May 23, 2019 05:39
supercavitation ALI1 CFX 1 March 22, 2010 14:07
supercavitation in CFX Alex CFX 2 December 18, 2006 23:26
SUPERCAVITATION mehrnaz FLUENT 0 March 16, 2004 08:56


All times are GMT -4. The time now is 19:54.