|
[Sponsors] |
April 22, 2005, 04:48 |
Hi,
When I activate turbule
|
#1 |
Member
Ervin Adorean
Join Date: Mar 2009
Posts: 76
Rep Power: 17 |
Hi,
When I activate turbulent dispersion in an axisymmetric diesel spray simulation, get this error: Create time Create mesh for time = 0 Reading thermophysicalProperties Selecting thermodynamics package hMixtureThermo<reactingmixture> Selecting chemistryReader chemkinReader Reading field U Reading/calculating face flux field phi Creating turbulence model. Selecting turbulence model RNGkEpsilon Creating field DpDt Constructing chemical mechanism Selecting ODE solver SIBS chemistryModel::chemistryModel: Number of species = 5 and reactions = 1 Reading environmentalProperties Reading combustion properties Constructing Spray Selecting injectorType commonRailInjector Selecting atomizationModel off Selecting dragModel standardDragModel Selecting evaporationModel standardEvaporationModel Selecting heatTransferModel RanzMarshall Selecting wallModel reflect Selecting breakupModel ReitzKHRT Selecting collisionModel trajectory Selecting dispersionModel gradientDispersionRAS --> FOAM FATAL ERROR : request for turbulenceModel turbulenceProperties from objectRegistry failed available objects of type turbulenceModel are 0 ( ) Function: objectRegistry::lookupObject<type>(const word&) const in file: /home/ervin/OpenFOAM/OpenFOAM-1.1/src/OpenFOAM/lnInclude/objectRegistryTemplates .C at line: 122. FOAM aborting Can somebody tell me what is this about, and how can this be corrected? Thanks. Ervin |
|
April 22, 2005, 05:03 |
looks like we forgot to change
|
#2 |
Super Moderator
Niklas Nordin
Join Date: Mar 2009
Location: Stockholm, Sweden
Posts: 693
Rep Power: 29 |
looks like we forgot to change this with the new change in runTime/mesh, Henry?
in dispersionRASModel.C change the line sm.runTime().lookupObject<compressible::turbulence model> to sm.mesh().lookupObject<compressible::turbulencemod el> and 'wmake libso' in the dieselSpray-dir. worked for me N |
|
April 22, 2005, 05:16 |
Worked for me too.
Thanks,
|
#3 |
Member
Ervin Adorean
Join Date: Mar 2009
Posts: 76
Rep Power: 17 |
Worked for me too.
Thanks, Niklas. Ervin |
|
April 22, 2005, 05:27 |
Well, now I've got myself a di
|
#4 |
Member
Ervin Adorean
Join Date: Mar 2009
Posts: 76
Rep Power: 17 |
Well, now I've got myself a different error message:
Time = 0.000585 Evolving Spray Solving chemistry BICCG: Solving for Ux, Initial residual = 0.0893508, Final residual = 3.71189e-08, No Iterations 4 BICCG: Solving for Uy, Initial residual = 0.0470008, Final residual = 8.18107e-07, No Iterations 3 BICCG: Solving for Uz, Initial residual = 0.00210555, Final residual = 4.94314e-08, No Iterations 3 BICCG: Solving for C7H16, Initial residual = 0.00283565, Final residual = 2.4395e-07, No Iterations 2 BICCG: Solving for O2, Initial residual = 0.00264662, Final residual = 8.18177e-07, No Iterations 2 BICCG: Solving for CO2, Initial residual = 0.00283727, Final residual = 2.09632e-07, No Iterations 2 BICCG: Solving for H2O, Initial residual = 0.00283727, Final residual = 2.09632e-07, No Iterations 2 BICCG: Solving for h, Initial residual = 0.00291149, Final residual = 3.13086e-07, No Iterations 2 ICCG: Solving for p, Initial residual = 0.62558, Final residual = 6.53001e-10, No Iterations 28 time step continuity errors : sum local = 3.69438e-12, global = -4.5675e-13, cumulative = -4.31118e-11 ICCG: Solving for p, Initial residual = 0.121549, Final residual = 5.99677e-10, No Iterations 27 time step continuity errors : sum local = 4.06811e-12, global = -8.22919e-13, cumulative = -4.39347e-11 BICCG: Solving for epsilon, Initial residual = 0.00106245, Final residual = 6.1007e-07, No Iterations 2 bounding epsilon, min: -1.59758e+11 max: 9.5401e+11 average: 2.79012e+08 BICCG: Solving for k, Initial residual = 0.4897, Final residual = 4.5726e-07, No Iterations 2 Number of parcels in system | 1101 Injected liquid mass....... | 3.26959 mg Liquid Mass in system...... | 1.13211 mg SMD, Dmax.................. | 13.5651 mu, 145.611 mu Added gas mass = 2.13748 mg Evaporation Continuity Error| 8.76679e-13 mg ExecutionTime = 294.19 s Max Courant Number = 2.12046 Time = 0.00059 Evolving Spray Solving chemistry BICCG: Solving for Ux, Initial residual = 0.0458617, Final residual = 9.53264e-07, No Iterations 3 BICCG: Solving for Uy, Initial residual = 0.158556, Final residual = 6.22212e-07, No Iterations 4 BICCG: Solving for Uz, Initial residual = 0.00461368, Final residual = 5.90762e-08, No Iterations 4 BICCG: Solving for C7H16, Initial residual = 0.00282151, Final residual = 2.05982e-07, No Iterations 3 BICCG: Solving for O2, Initial residual = 0.00261989, Final residual = 3.43801e-07, No Iterations 3 BICCG: Solving for CO2, Initial residual = 0.00304074, Final residual = 5.55743e-07, No Iterations 3 BICCG: Solving for H2O, Initial residual = 0.00304074, Final residual = 5.55743e-07, No Iterations 3 BICCG: Solving for h, Initial residual = 0.00385778, Final residual = 6.85247e-07, No Iterations 3 --> FOAM FATAL ERROR : attempt to use janafThermo<equationofstate> out of temperature range 200 -> 5000; T = 191.289 Function: janafThermo<equationofstate>::checkT(const scalar T) const in file: /home/ervin/OpenFOAM/OpenFOAM-1.1/src/thermophysicalModels/specie/lnInclude/jana fThermoI.H at line: 73. FOAM aborting How can this error be corrected/prevented? Ervin |
|
April 22, 2005, 06:02 |
Hi Niklas,
Yes this is a bu
|
#5 |
Senior Member
Join Date: Mar 2009
Posts: 854
Rep Power: 22 |
Hi Niklas,
Yes this is a bug in 1.1, you also need to make the eqivalent change in dispersionLESModel.C: sm.runTime().lookupObject<compressible::lesmodel> to sm.mesh().lookupObject<compressible::lesmodel> I have fixed this for 1.1.1 H |
|
April 22, 2005, 06:39 |
The above mentioned 'out of te
|
#6 |
Member
Ervin Adorean
Join Date: Mar 2009
Posts: 76
Rep Power: 17 |
The above mentioned 'out of temperature range' error happened because of an ill imposed wall temp. bc (I think). I've changed to fixedValue uniform 293 K and it worked.
Ervin |
|
April 22, 2005, 06:55 |
Hi,
the 'out of temperature
|
#7 |
Super Moderator
Niklas Nordin
Join Date: Mar 2009
Location: Stockholm, Sweden
Posts: 693
Rep Power: 29 |
Hi,
the 'out of temperature range' is a secondary effect of a 'crashed' run, look at the courant number 2.1!!! try keeping the courant number low. The problem with spray calculations are that if you have large/sudden variation in injection velocity the added momentum, or energy, can be substantial and you will get this kind of error. N |
|
Thread Tools | Search this Thread |
Display Modes | |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Running dieselFoam error | adorean | OpenFOAM Running, Solving & CFD | 119 | February 1, 2016 14:41 |
DPM turbulent dispersion | Springbok | Main CFD Forum | 0 | July 15, 2008 04:14 |
Turbulent Dispersion in Particle Tracking | ariel | CFX | 2 | April 22, 2008 22:02 |
Turbulent dispersion | Julie Polyakh | Siemens | 0 | May 15, 2003 07:14 |
turbulent dispersion of particles! | danney | CFX | 0 | April 2, 2003 09:17 |