
[Sponsors] 
May 20, 2019, 06:36 

#61  
Senior Member
Daniel
Join Date: Mar 2013
Location: Noshahr, Iran
Posts: 348
Rep Power: 19 
Quote:
Well I'm interested Would you please share your findings? I'm trying to do the exact same thing. Regards 

April 17, 2020, 08:49 
Energy equation

#62 
New Member
saeedbd
Join Date: Feb 2015
Posts: 6
Rep Power: 9 
Hi foamers,
I am working on CompressibleInterFoam. I want to convert the T equation to a general energy conservation equation to remove some assumptions in the solver. Could you finally manage the energy equation? Assuming the perfectGas and perfectFluid Eos, we have e=Cv*T for each phase where e is internal energy. So, I am replacing T with et/(Cv_water Y_water + Cv_air Y_air) in the solver (et is the total internal energy with et = e1*Y1 + e2*Y2. But it gives me wrong results for bubble collapse case. So in fact, the T equation in original solver is as: Code:
fvScalarMatrix TEqn ( fvm::ddt(rho, T) + fvm::div(rhoPhi, T)  fvm::Sp(contErr, T)  fvm::laplacian(turbulence.alphaEff(), T) + ( fvc::div(fvc::absolute(phi, U), p)()() //  contErr/rho*p + (fvc::ddt(rho, K) + fvc::div(rhoPhi, K))()()  contErr*K ) *( alpha1()/mixture.thermo1().Cv()() + alpha2()/mixture.thermo2().Cv()() ) == fvOptions(rho, T) ); and now is converted to Code:
fvm::ddt(rho, et) + fvm::div(rhoPhi, et)  fvm::Sp(contErr, et)  fvm::laplacian(turbulence.alphaEff(), et) + ( fvc::div(fvc::absolute(phi, U), p)()() //  contErr/rho*p + (fvc::ddt(rho, K) + fvc::div(rhoPhi, K))()()  contErr*K ) *( alpha1()/mixture.thermo1().Cv()() + alpha2()/mixture.thermo2().Cv()() ) *( Y1*mixture.thermo1().Cv()()+Y2*mixture.thermo2().Cv()() ) == fvOptions(rho, et) where Y is the mass fraction: et=Y1*e1 + Y2*e2 and e1=Cv1*T , e2=Cv2*T. Also, I tried: Code:
fvm::ddt(rho, et) + fvm::div(rhoPhi, et)  fvm::Sp(contErr, et)  fvm::laplacian(turbulence.alphaEff(), et) + ( fvc::div(fvc::absolute(phi, U), p)()() //  contErr/rho*p + (fvc::ddt(rho, K) + fvc::div(rhoPhi, K))()()  contErr*K ) == fvOptions(rho, et) But it does not work properly as well. The temperature drops at the interface immediately. In more details, I don't know why et in the new energy equation remains constant while I checked that we have velocity and K is NOT zero! (How can it be possible?) Then, after a very small time step 10^12, since we have Y_water = 0.1 in the gas side of the interface, Temperature drops suddenly according to T = et/(Cv_water*Y_water + Cv_air*Y_air). The last point, it gives good results for the shock tube case which is not very dependent on temperature and energy. Do you know how to solve the issue? Thank you for your time. Saeed, 

April 17, 2020, 13:19 

#63 
Super Moderator
Tobias Holzmann
Join Date: Oct 2010
Location: Tussenhausen
Posts: 2,654
Blog Entries: 6
Rep Power: 48 
Hi,
so I am not familiar with the solver you are using and I am also not familiar with its equation. However, VOF solves only one question for energy/momentum and so on. Just one question, you are solving for the field et, which is what? An energy right, the total internal energy. So, how do you transform the energy back into the temperature? I cannot see anything here. Because, as you are not solving for T anymore, the T field should stay constant. So actually, what you have to do is:
Hope this might help. Tobi
__________________
Keep foaming, Tobias Holzmann 

April 17, 2020, 13:44 

#64 
New Member
saeedbd
Join Date: Feb 2015
Posts: 6
Rep Power: 9 
Hi Tobi,
Thank you very much for giving your feedback. Regarding the Temperature, I am obtaining it within the T = et/(Cv_water*Y_water + Cv_air*Y_air) equation which is based on perfectFluid and perfectGas. So to put it into a nutshell, I initialize the system with et=e1Y1+e2*Y2 and then solve the et equation. Then I update the T, based on the new et using the above equation. Best, 

April 17, 2020, 14:32 

#66 
New Member
saeedbd
Join Date: Feb 2015
Posts: 6
Rep Power: 9 
Yes with the considered EoSs.
I found an issue with the defined tolerance for et. So now it is being solved and this problem "I don't know why et in the new energy equation remains constant" is solved. 

April 29, 2020, 04:26 

#67 
New Member
Zhongqi Zuo
Join Date: May 2018
Location: China
Posts: 5
Rep Power: 5 
Hi openFoamers,
Thanks for your great discussion, it really helps a lot. However, when I look through the code, I find this term very confusing to me Code:
p_rghEqnComp1 & p_rgh But as I know & is "inner product", the operator is redefined in fvMatrix.C. p_rghEqnComp1 is a fvMatrix, p_rgh is a scalar field, how can the term be interpreted as Dp/Dt? Anybody can help? Thanks a lot. Zuo 

September 9, 2021, 15:36 

#68 
Member
Zé
Join Date: Feb 2020
Posts: 90
Rep Power: 4 
Hello to all,
I am also trying to understand the formulation of compressibleInterFoam for OpenFOAM ESI. However, the formulation is not clear to me. I would like to request a further clarification on the formulation of compressibleInterFoam. From the paper of Miller et al [1], previously referred to in this post, the pressure equation should be: Or, to better use the divergence theorem: With the last term on the lefh hand side, , we create a incompressiblePEqn and with the remainder terms a compressiblePEqn. I took a look into the compressibleInterFoam from foamexted. The pEqn.H has: An incomplete CompressiblePEqn written as: Code:
if (pimple.transonic()) { pEqnComp = (fvm::ddt(p) + fvm::div(phi, p)  fvm::Sp(fvc::div(phi), p)); } else { pEqnComp = (fvm::ddt(p) + fvc::div(phi, p)  fvc::Sp(fvc::div(phi), p)); } The incompressiblePEqn which is derived by substituting the cell center velocity from the momentum equation. Code:
fvScalarMatrix pEqnIncomp ( fvc::div(phi)  fvm::laplacian(rUAf, p) ); Code:
solve ( ( max(alpha1, scalar(0))*(psi1/rho1) + max(alpha2, scalar(0))*(psi2/rho2) ) *pEqnComp() + pEqnIncomp ); After solving the pressure equation, a dgdt term is updated with: Code:
dgdt = (pos(alpha2)*(psi2/rho2)  pos(alpha1)*(psi1/rho1)) *(pEqnComp & p); Here are my questions: 1º Is the formulation used in [1], the one in compressibleInterFoam? 2º Is it the same formulation on all branches of OpenFOAM (ESI, ORG and extend)? 3º is dtdg = right and side of the above equation? 4º What is the purpose of doing the dot product (&) between a scalarMatrix and a volScalarField? What is the mathematical representation of this operation? 5º In OpenFOAM(ESI) the compressible part (nontransonic) of the pressure equation we have: Code:
p_rghEqnComp1 = pos(alpha1) *( ( fvc::ddt(alpha1, rho1) + fvc::div(alphaPhi1*rho1f)  (fvOptions(alpha1, mixture.thermo1().rho())&rho1) )/rho1  fvc::ddt(alpha1)  fvc::div(alphaPhi1) + (alpha1*psi1/rho1)*correction(fvm::ddt(p_rgh)) ); Code:
fvc::ddt(alpha1, rho1) + fvc::div(alphaPhi1*rho1f)  (fvOptions(alpha1, mixture.thermo1().rho())&rho1) )/rho1  fvc::ddt(alpha1)  fvc::div(alphaPhi1) 6º Apart from [1] is there any other literature on the formulation of compressibleInterFoam? Best Regards!  [1] Miller, S. T., Jasak, H., Boger, D. A., Paterson, E. G., & Nedungadi, A. (2013). A pressurebased, compressible, twophase flowa finite volume method for underwater explosions. Computers and Fluids, 87, 132–143. https://doi.org/10.1016/j.compfluid.2013.04.002 

December 30, 2021, 01:04 

#69 
Member
hari charan
Join Date: Sep 2021
Location: India,hyderabad
Posts: 60
Rep Power: 2 
Hi Nat,
I know the post is old. But can you describe the evolution of step 4 mathematically instead of describing it in words? Thanks in advance. 

December 30, 2021, 01:47 

#70 
Member
hari charan
Join Date: Sep 2021
Location: India,hyderabad
Posts: 60
Rep Power: 2 
Hello nat,
Can u explain the evolution of step 3 to step 4 using math instead of words. Thanks in advance. 

Tags 
compressible, compressibleinterfoam, theory 
Thread Tools  Search this Thread 
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Low Reynolds Number kepsilon formulation CFX 10.0  Chris  CFX  4  December 7, 2009 23:51 
Immersed Boundary Formulation  Rave  Main CFD Forum  0  August 11, 2008 14:55 
DPM Steady formulation with collisions  kulwinder  FLUENT  0  May 22, 2004 18:44 
energy equation formulation  Pedro  Phoenics  1  July 5, 2001 12:17 
Compressible vs. Incompressible formulations  Fernando Velasco Hurtado  Main CFD Forum  3  January 7, 2000 16:51 