CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > Siemens > STAR-CCM+

Bad Convergence on Complete Aircraft Analisys

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   October 6, 2015, 22:04
Angry Bad Convergence on Complete Aircraft Analisys
  #1
New Member
 
Join Date: Oct 2015
Posts: 5
Rep Power: 7
arthurdiasBR is on a distinguished road
I'm a new user of Star-ccm+ Trying to simulate a canard Type aircraft in the following flow:
P = 69820 Pa
T = 268.3380 K
V = 87.45556 m/s
M = 0.2663
Rho= 0.9046 kg/m

my set up:
three-dim
steady
segregated flow
(Green-Gauss)
constant density
Turbulent
K-omega
All y+ treatment

For some reason I cant get a 1e-4 convergence, not even 1e-3 in the residuals.

My mesh is an Unstructured mesh (Tetra) with a prism layer with y+ =32
Here are some pics from the mesh:

does anybody has some tip for me so I can improve the convergence?
arthurdiasBR is offline   Reply With Quote

Old   October 7, 2015, 20:18
Default
  #2
Senior Member
 
Join Date: Nov 2010
Location: USA
Posts: 1,232
Rep Power: 21
me3840 is on a distinguished road
Your mesh is way, way too coarse. There's no wake refinement at all.

Why are you using an ANSYS mesher and a tet grid?
me3840 is offline   Reply With Quote

Old   October 7, 2015, 22:13
Default
  #3
New Member
 
Join Date: Oct 2015
Posts: 5
Rep Power: 7
arthurdiasBR is on a distinguished road
i'm using a mesh with 6.6 million cells approximatelly, it is for an article in canard airplanes regarding their aerodynamics in the general aviation.
I've never dealt with cfd meshes before as so I was told that the mesh itself was "good". I put 22 layers of prisms for boundary layer calculation wich gives me y+=32. The thing is that I don't know how to make another type of mesh on ICEM other than tet mesh with prisms. I've notice that even though I smooth the mesh till 0.38 minimum quality I keep getting bad quality after building the prisms layers. I'm short on time so I think that any tip regarding geting a good quality mesh (Tet with prisms) will make it work.

My computational resourses are somewhat limited to a i7,24gb, 12 cores computer. For now i'm studying the relation between the size of the domain in the calculation of lift and drag which is very difficult because the solver doesn't give me good convergence.

Last edited by arthurdiasBR; October 7, 2015 at 22:16. Reason: adding more technical info
arthurdiasBR is offline   Reply With Quote

Old   October 7, 2015, 22:41
Default
  #4
Senior Member
 
Join Date: Nov 2010
Location: USA
Posts: 1,232
Rep Power: 21
me3840 is on a distinguished road
You're posting in a STAR-CCM+ forum, but you seem to be using ANSYS products, which I don't really understand. STAR-CCM+ has excellent easy-to-use meshers. But for a situation like this you should really be using a hex/trim grid or a polymesh. Tets are very diffusive. I guess the good part for you is tets are relatively memory cheap.

6.6M cells is pretty coarse for aero. With your CPU limitations I would cut the number of prisms in half and spend more on wake refinement. Lower the growth rate around the aircraft and do wake refinement. It should be very easy to see where your total pressure gradients are too coarse if you do some cutplanes.

You are very limited on memory resources, you can probably max out at 16M or so cells.

If by quality you mean skewness, 0.38 is very good quality for Fluent's skewness criterion. You can probably put your worst cell at 0.75 or so and be fine.

If that's STAR-CCM+'s cell quality criterion, you can probably lower it to 0.1 and be fine.
me3840 is offline   Reply With Quote

Reply

Tags
aircraft, convergence, set-up, solver control, star-ccm+

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
good convergence but bad display zaynah04 OpenFOAM 17 January 10, 2013 02:00
Problems with convergence with an easy system franzdrs Main CFD Forum 0 June 15, 2009 19:17
increasing mesh quality is leading to poor convergence tippo CFX 2 May 5, 2009 11:55
too bad convergence Davoche Main CFD Forum 2 November 20, 2005 06:08
Problems of Duns Codes! Martin J Main CFD Forum 8 August 15, 2003 00:19


All times are GMT -4. The time now is 03:09.