CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > Siemens > STAR-CCM+

Star CCM+ Drag and Lift Forces/Coefficients drifting downwards

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   March 16, 2016, 09:43
Unhappy Star CCM+ Drag and Lift Forces/Coefficients drifting downwards
  #1
New Member
 
Rebecca
Join Date: Mar 2016
Posts: 4
Rep Power: 10
Bekka is on a distinguished road
Hi,

I'm undertaking a study at the moment on the drag and lift forces of a vehicle. All my residuals/mesh/pressures etc seem to be what I expected. However, my drag and lift forces and coefficients keep drifting downwards and I can't work out why.

Does any body have any ideas?

Thanks!
Bekka is offline   Reply With Quote

Old   March 16, 2016, 17:41
Default
  #2
Senior Member
 
scipy's Avatar
 
Alex Pasic
Join Date: Aug 2011
Location: Croatia
Posts: 199
Rep Power: 15
scipy is on a distinguished road
Send a message via Skype™ to scipy
What do you mean by "drifting downwards"? If your solution has not converged yet, then just give it more time/iterations until force/coefficient monitors level out.

If on the other hand you mean the values are too small, did you properly set reference values for coefficient calculation (such as vehicle's projected frontal surface area)?
__________________
If you're in need of some free quality CFD video tutorials - check out SiriusCFD @ YouTube
scipy is offline   Reply With Quote

Old   March 17, 2016, 04:40
Default
  #3
New Member
 
Rebecca
Join Date: Mar 2016
Posts: 4
Rep Power: 10
Bekka is on a distinguished road
Yes, the values are much lower than expected and the more iterations completed, the lower they seem to get.

Yes, all reference values e.g. density/frontal area/relative velocity have been filled in correctly.... Completely at a loss with what could be wrong
Bekka is offline   Reply With Quote

Old   March 17, 2016, 04:49
Default
  #4
Senior Member
 
scipy's Avatar
 
Alex Pasic
Join Date: Aug 2011
Location: Croatia
Posts: 199
Rep Power: 15
scipy is on a distinguished road
Send a message via Skype™ to scipy
Can you post a screenshot of a convergence graph for Cd/Cl or something? If they're asymptotically getting closer to some "value" then let it run until the values level out. However, if they're just obviously wrong then I don't know.

Are you using symmetry? Did you set only the half of the frontal area as the reference value? Did you select all the walls of the vehicle in the force calculation (maybe you missed some of them)?
__________________
If you're in need of some free quality CFD video tutorials - check out SiriusCFD @ YouTube
scipy is offline   Reply With Quote

Old   March 17, 2016, 05:58
Default
  #5
New Member
 
Rebecca
Join Date: Mar 2016
Posts: 4
Rep Power: 10
Bekka is on a distinguished road
No, I havent used symmetry due to the kart i'm using not being symmetrical. I've been through my set up numerous times and can't find anything wrong.

I've attached screen shots of the force plots and residuals

Drag Plot.PNG

Lift Froce.PNG

Residuals.PNG
Bekka is offline   Reply With Quote

Old   March 17, 2016, 16:46
Default
  #6
Senior Member
 
scipy's Avatar
 
Alex Pasic
Join Date: Aug 2011
Location: Croatia
Posts: 199
Rep Power: 15
scipy is on a distinguished road
Send a message via Skype™ to scipy
This all looks pretty normal/standard to me. I don't know how large your mesh is, but I had convergence graphs that looked exactly like this. Some playing with under-relaxation factors might help to "calm" things down a bit (I'm assuming a steady-state simulation) and more iterations may be needed to get the forces to level out (again, depends on the solver.. but even using a Coupled version of the solver I needed ~1000 or more to converge cases of 8-12 million elements).
__________________
If you're in need of some free quality CFD video tutorials - check out SiriusCFD @ YouTube
scipy is offline   Reply With Quote

Old   March 22, 2016, 08:47
Default
  #7
Senior Member
 
Matt
Join Date: Aug 2014
Posts: 947
Rep Power: 17
fluid23 is on a distinguished road
I would argue that 650 iterations is probably no where near enough to call this converged. In a lot of external aero cases I find that my residuals sometimes appear to converge before the engineering values (lift, drag, mass flow rate) sometimes level out. I would AT A MINIMUM, run another 650 iterations before making any judgement about stability of your values (i.e. their drift).

As for your forces being low I would suggest checking that your mesh is appropriate. Make sure wall y+ is appropriate. That you don't have any large volume changes or skewness issues. I would also verify that you have the dimensions you think you do. Sometimes CAD imports or improper unit system selection can cause you to have bodies that are quiet a bit smaller or larger than what you intended. You may be putting the right constants into the report, but you should make sure that those match your model. Also, make sure you are refining the wake otherwise you aren't really capturing what is going on with your drag values.
fluid23 is offline   Reply With Quote

Old   November 3, 2023, 17:58
Default
  #8
New Member
 
George Halliday
Join Date: Sep 2023
Posts: 6
Rep Power: 2
GeorgeH25 is on a distinguished road
Does anyone know how to fix a unable to compute error showing up in force coefficient report?

I have everything as it should in the coordinates, pressure and part regions but it keeps saying unable to compute and no data

the frontal area reports on the same parts so I'm not sure what is going on?

Thank you
GeorgeH25 is offline   Reply With Quote

Reply

Tags
cfd, lift and drag, star ccm+

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
How to calculate lift, drag and lift distribution in Star CCM+? israelcasillas94 STAR-CCM+ 4 November 6, 2020 08:35
wrong SU2 calculation for lift and drag coefficient for NAC4421 mechy SU2 7 January 9, 2017 05:18
[OpenFOAM] Display lift and Drag in paraview SamerAli ParaView 1 May 16, 2013 12:51
Lift and Drag Monitor Point Values Converging to Zero Josh CFX 24 May 9, 2011 10:38
Correct lift but wrong pressure drag - possible? zx Main CFD Forum 4 July 27, 2007 23:38


All times are GMT -4. The time now is 00:47.