CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > Siemens > STAR-CCM+

boundary layer mesh resolution

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree2Likes
  • 1 Post By ping
  • 1 Post By Roman

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   November 1, 2016, 14:39
Default boundary layer mesh resolution
  #1
New Member
 
Stan
Join Date: May 2016
Posts: 6
Rep Power: 6
mecha1705 is on a distinguished road
hi everyone;
i am trying to simulate conjugate, transient external supersonic flow around a blunt body. is there any rule of thumb for boundary layer mesh parameters. is y+ only parameter to control. any suggestions and experiences are welcome.
mecha1705 is offline   Reply With Quote

Old   November 14, 2016, 23:26
Default
  #2
Senior Member
 
Ping
Join Date: Mar 2009
Posts: 553
Rep Power: 17
ping is on a distinguished road
the help has a best practise guide called Transonic/Supersonic External Aerodynamics: Steady State RANS Approach which has lots of good tips on all aspects of model setup
ping is offline   Reply With Quote

Old   November 18, 2016, 16:24
Default
  #3
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 4,101
Rep Power: 49
LuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura about
# of points across the boundary layer is much more important than y+
y+ affects which regime the wall models and wall boundary conditions fall under but # of points across the boundary layer is, quite literally, the boundary layer mesh resolution.

Target 8 or 10 points in the boundary layer, or 30, etc.
LuckyTran is offline   Reply With Quote

Old   November 20, 2016, 07:25
Default
  #4
Senior Member
 
Ping
Join Date: Mar 2009
Posts: 553
Rep Power: 17
ping is on a distinguished road
it is far less simple than that and some of that advice is incorrect. if you chose the all y+ wall method the code will choose the best method based on the local y+ but you should still obey the mesh requirements for each. to use wall functions y+ should be between about 30 and 150 and the first cell is thus large enough to cover the viscous sublayer and boundary layer and cells beyond this should grow at a reasonable rate to then match the local core mesh size so if the prism layer is about the size of the core mesh then you only really need one prism layerbut for a low reynolds number mesh where y+ is <=1 you need to integrate across the viscous sub layer with 10-20 layers growing slowly and ensuring these capture the full boundary layer and also meet the core mesh at about the same size which sometimes takes 50 layers
Gerhard likes this.
ping is offline   Reply With Quote

Old   November 20, 2016, 09:13
Default
  #5
Member
 
Roman
Join Date: Mar 2011
Posts: 46
Rep Power: 12
Roman is on a distinguished road
As mentioned above; Good resolution of boundary layer. Do a test 2D sim/ hand calculations to determine height of your boundary layer and layers needed to have good representation of the velocity profile. I would estimate anything from 10 - 30 layers with standard air density and dynamic viscosity.

I also agree with ping, wall y+ should not be above 300, you will get unreliable results in shear forces. If you can afford it, try to adjust your first prism cell size to a height that gives you y+ approximately 1. otherwise y+ 30-50 is fine.

Important, y+ values and resolution of boundary layer velocity profile are not the same thing, if you do a good job on both of them you will get reliable results.

Roman
Gerhard likes this.
Roman is offline   Reply With Quote

Old   November 20, 2016, 11:53
Default
  #6
New Member
 
Stan
Join Date: May 2016
Posts: 6
Rep Power: 6
mecha1705 is on a distinguished road
thank you for your replies. i will take into account your valuable advices.
mecha1705 is offline   Reply With Quote

Reply

Tags
boundary layer mesh

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Radiation in semi-transparent media with surface-to-surface model? mpeppels CFX 11 August 22, 2019 07:30
[mesh manipulation] Importing Multiple Meshes thomasnwalshiii OpenFOAM Meshing & Mesh Conversion 18 December 19, 2015 18:57
Moving mesh Niklas Wikstrom (Wikstrom) OpenFOAM Running, Solving & CFD 122 June 15, 2014 06:20
Radiation interface hinca CFX 15 January 26, 2014 17:11
Convective Heat Transfer - Heat Exchanger Mark CFX 6 November 15, 2004 15:55


All times are GMT -4. The time now is 01:07.