|
[Sponsors] |
Transient Blade Row model Fourier transformation error |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
April 12, 2016, 02:37 |
Transient Blade Row model Fourier transformation error
|
#1 |
New Member
Junsoo Kim
Join Date: Nov 2015
Posts: 2
Rep Power: 0 |
Hello everyone.
I am trying to analyze gas turbine 1st stage with transient blade row model. I am using fourier transformation and Rotor-stator option(beta feature). In the display monitor, the message at below has displayed. ERROR #999100267 has occurred in subroutine gKCsFCCsPS. Message: Unable to compute interface connectivity between the following domain interfaces: Phase Corrected domain interface : R1 to R1 Periodic 1 Sampling domain interface : R1 Internal Interface 2 for this serial/partitioning run. Likely causes are: 1) The mesh has been transformed using single precision arithmetic at some point. 2) The single precision solver/partitioner is being used instead of the double precision solver/partitioner as recommended for the Fourier Transformation model. If 2) is not the case please increase the expert parameter "ps mapping check tolerance" to a Value larger than the current value: 1.000E-04. I confirmed that mesh has been transformed using double precision, and also double precision solver is being used. So I looked for "ps mapping check tolerance" but there wasn't any tolerance like that in expert parameters. I am using ANSYS 15.0 and If someone have any idea of this, please give me any advice. Thank you. |
|
April 12, 2016, 12:29 |
|
#2 |
Senior Member
Join Date: Jun 2009
Posts: 1,876
Rep Power: 33 |
I am not sure, but I think the Phase Corrected Interface and the Sampling Interface are not physically matching.
The name for the Sampling Interface being suggest it is referring to tip gap interface (usually named <Component> Internal Interface <N>) instead of the sampling interface between the two passages. Hope the above helps, |
|
May 30, 2016, 09:53 |
|
#3 | |
New Member
Jessica Wei
Join Date: Mar 2016
Posts: 6
Rep Power: 10 |
Hello!
Do you solve the problem yet? I'm using CFX 16.0 TBR-FT now and facing the same problem. Could you help me on this please? Thank you very much. Quote:
|
||
October 19, 2016, 14:03 |
Same problem in Fourier Transformation method
|
#4 |
New Member
vahid
Join Date: Nov 2015
Posts: 8
Rep Power: 11 |
I am simulating a Francis turbine using FT Method and I have the same problem , have you solved the problem? If yes, How do you solved the problem?
|
|
March 2, 2017, 17:58 |
|
#5 |
Senior Member
Have a nice time!
Join Date: Feb 2016
Location: mech.eng.ahmedmansour@gmail.com
Posts: 291
Rep Power: 11 |
||
November 30, 2017, 10:36 |
Error
|
#6 |
Senior Member
Davide
Join Date: Jul 2015
Posts: 107
Rep Power: 11 |
Has someone solved this error? Also me have the same problem, I followed the youtube guide modeling impeller vaneless volute but the partitioner interruptes with the same error
|
|
December 4, 2017, 17:19 |
|
#7 |
Senior Member
Join Date: Jun 2009
Posts: 1,876
Rep Power: 33 |
Two things to keep in mind:
When doing replicating the mesh for the passage, you must use the Turbo Rotation option. Do not use the Rotation option unless you are going to type 16 decimal digits for the rotation angle. Once the definition file is created, you must always run in double precision for Fourier Transformation cases. Both items are mentioned in the documentation for transient blade row guidelines. |
|
July 16, 2018, 13:04 |
|
#8 | |
New Member
Join Date: Apr 2014
Posts: 13
Rep Power: 12 |
Quote:
|
||
July 16, 2018, 13:05 |
|
#9 |
New Member
Join Date: Apr 2014
Posts: 13
Rep Power: 12 |
||
July 17, 2018, 11:33 |
|
#10 |
Senior Member
Have a nice time!
Join Date: Feb 2016
Location: mech.eng.ahmedmansour@gmail.com
Posts: 291
Rep Power: 11 |
Hello dear Young I do not remember why I did write this reply anyway tell me about your machine type and the problem again, also, you can watch my tutorials about CFX setup, they may help you more...the playlist is attached, it contains all the simulations...Danke!
https://www.youtube.com/watch?v=QfSe...xqdJbZmagGCTop |
|
July 19, 2018, 11:41 |
|
#11 | |
New Member
Join Date: Apr 2014
Posts: 13
Rep Power: 12 |
Quote:
The problem is solved anyway. I will note it down later in this post. Best regards,\Yang |
||
July 19, 2018, 11:48 |
Possible solution to this error
|
#12 |
New Member
Join Date: Apr 2014
Posts: 13
Rep Power: 12 |
Dear all,
After fighting against this error for days, I found my solution. So I just note it down here. If someone happened to encounter the same problem, check this first. The reason for my error comes from the steady state CFD calculation, which is used to initialize transient CFD calculation. It should be calculated with double precision. But before, I did not notice that from the CFX tutorial. Actually, this is also mentioned in CFX manual. Best regards, Young |
|
July 19, 2018, 13:12 |
|
#13 |
Senior Member
Have a nice time!
Join Date: Feb 2016
Location: mech.eng.ahmedmansour@gmail.com
Posts: 291
Rep Power: 11 |
Thanks,
|
|
October 15, 2018, 16:40 |
|
#14 |
New Member
mohammad karimi pour
Join Date: Oct 2018
Posts: 6
Rep Power: 8 |
I checked the double precision button for both steady state and transient blade row; as well as changing cfx (beta) to cfx Transient Blade Row: RotorStator FOURIER TRANSFORMATIONbut still the error exists. What else do you think could cause this problem?
|
|
October 16, 2018, 10:47 |
|
#15 |
Senior Member
Join Date: Jun 2009
Posts: 1,876
Rep Power: 33 |
The Fourier Transformation model requires two passages. The usual way for obtaining the two passages is to mesh a single passage, and replicate the passage one more time by one pitch.
In CFX-Pre, there are two option for the replication: Rotation: it requires the angle to be rotated, i.e. one pitch. If using this option, you must enter as many significant digits as possible, and even then it does not guarantee it will be perfect. Turbo Rotation: it requires information about the blade row: passages in 360, passages to be modeled, and passages in the provided mesh. This method has minimal roundoff, and it is the most used for turbomachinery modeling. The above must be done from the steady-state solution setup, and throughout any variants of the setup. It is not only about running the ANSYS CFX Solver in double precision. |
|
October 17, 2018, 16:18 |
|
#16 |
New Member
mohammad karimi pour
Join Date: Oct 2018
Posts: 6
Rep Power: 8 |
Thank you for your reply.
Although it didn't solve my problem, I'll consider it whenever I have to replicate a mesh. I also cannot find the expert parameter: "ps mapping check tolerance" |
|
October 18, 2018, 14:37 |
|
#17 |
Senior Member
Join Date: Jun 2009
Posts: 1,876
Rep Power: 33 |
Is your mesh conformal (1:1), or largely non-conformal between the periodics, and the sampling interface?
|
|
October 20, 2018, 17:25 |
|
#18 |
New Member
mohammad karimi pour
Join Date: Oct 2018
Posts: 6
Rep Power: 8 |
Both of them are conformal. Do you think I should change it?
|
|
Thread Tools | Search this Thread |
Display Modes | |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
[OpenFOAM] an error in Calculator's equation | immortality | ParaView | 12 | June 29, 2021 01:10 |
Undeclared Identifier Errof UDF | SteveGoat | Fluent UDF and Scheme Programming | 7 | October 15, 2014 08:11 |
How to install CGNS under windows xp? | lzgwhy | Main CFD Forum | 1 | January 11, 2011 19:44 |
checking the system setup and Qt version | vivek070176 | OpenFOAM Installation | 22 | June 1, 2010 13:34 |
user subroutine error | CFDUSER | CFX | 2 | December 9, 2006 07:31 |