# Liquid head due to gravity in CFX

 User Name Remember Me Password
 Register Blogs Members List Search Today's Posts Mark Forums Read

 Sponsored Links

 LinkBack Thread Tools Display Modes
 September 19, 2005, 13:27 Liquid head due to gravity in CFX #1 tuks Guest   Posts: n/a Sponsored Links Hi friends, How can we incorporate the Liquid head due to gravity in CFX? Can it be added as volumetric source term (density*g*h) in particular direction (say z direction) or we have to give CEL for pressure? I just want to solve simple flow in tank problem. Thanks in advance Regards Tuks
 Sponsored Links

 September 20, 2005, 07:31 Re: Liquid head due to gravity in CFX #2 Rui Guest   Posts: n/a Hi, Are you solving a two-phase (liquid+air) free-surface problem, or just a one-phase problem? If it is a two-phase free-surface problem, you'll have to define the buoyancy refence density (Rho_ref) and the gravity vector (g). This will add a momentum source SM=(Rho-Rho_ref)*g . Rho_ref is usually set to the air density. If it is just a one-phase flow, you may define the 3 components of the momentum source as:SMx=Rho*gx ; SMy=Rho*gy ; SMz=Rho*gz However, you will obtain theoretically the same results (if your fluid properties, including density of course, are independent of pressure) if in Post you add the the gravity contribution to pressure, P'=P+Pg, Pg=Rho*g*h . And this is probably what you should do, as in this way CFX solves the pressure field caused only by the flow itself.

 September 20, 2005, 09:00 Re: Liquid head due to gravity in CFX #3 Tuks Guest   Posts: n/a Hi Rui, Thank you for your advice. I am solving the single phase problem and tried with SMx=Rho*gx, but the solution is diverging. Anyway i got the rid of problem, it was fairely simple, i tried with buoyancy for single phase (gx only) and it worked. No need to define as source. But still Question remains that why didn't it worked when defined as source term?. Thank again you for kind advice. Regards Tuks

 September 20, 2005, 11:03 Re: Liquid head due to gravity in CFX #4 Rui Guest   Posts: n/a Hi, When you defined Buoyancy, did you define a Buoyancy Reference Density or a Buoyancy Reference Temperature?As I think for a single phase, if the fluid density is constant CFX only allows you to employ the Bussinesq buoyancy model which requires a Buoyancy Reference Temperature. When you tried SMx=Rho*gx, have you defined the g vector direction correctly (downwards)? Have you specified the initial pressure taking into account the gravity effect (P=Rho*g*h)?

 September 22, 2005, 04:16 Re: Liquid head due to gravity in CFX #5 Tuks Guest   Posts: n/a Hi Rui, Thank you for your advice. Regarding the buoyancy, i had defined the Ref Temp. Bussineqs aprrox doesnot matter for me because the conditions are isothermal. About the SMx=Rho*gx, i had defined the correct direction. The pressure was also intialised using P=Rho*g*h, with Pref=101325[Pa]. But still it didnot work and i had to go for Buoyancy approach. Regards Tuks

 September 22, 2005, 07:19 Re: Liquid head due to gravity in CFX #6 Rui Guest   Posts: n/a Hi, If you see the CFX-5.7.1 documentation, Solver Theory, Basic Solver Theory, Buoyancy pages 24-25, when using the Bussinesq Model the momentum source term is: SM = -Rho*Beta*(T-T_ref)*g , where Beta is Thermal Expansivity of your fluid (defined in Material Properties). Thus, this won't give the pressure head due to gravity.If you have performed any simulation with this model, you should be able to check this in CFX-Post. Pref doesn't have any influence on the calculations (if all the fluid properties are independent of pressure), it's just a value that is added to the pressure actually calculated by the Solver. How have you defined the boundary conditions?When does the simulation diverges? After a few iterations? Regards, Rui

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post Val Main CFD Forum 3 June 10, 2011 02:20 Jinx CFX 3 January 28, 2010 17:31 Tuks Main CFD Forum 0 September 20, 2005 01:13 Pandu Sattvika CFX 1 December 1, 2001 05:07 Drona CFX 7 November 22, 2001 11:28

 Sponsored Links

All times are GMT -4. The time now is 00:08.

 Contact Us - CFD Online - Top