CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > CFX

boundary layer specifications for laminar flow

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Display Modes
Old   November 20, 2007, 04:24
Default boundary layer specifications for laminar flow
  #1
ranjith
Guest
 
Posts: n/a
I am new to cfd. I am modelling blood flow through a pipe with a valve at the centre. Assuming the flow is laminar is the boundary layer resolution and the number of prism layers important. I could find specifications(y+ ranges) for turbulent flow but none for laminar flow.would greatly appreciate any help
  Reply With Quote

Old   November 20, 2007, 04:46
Default Re: boundary layer specifications for laminar flow
  #2
frank
Guest
 
Posts: n/a
in my opinion, y+ is only for turbulence flow, not for laminar flow.
  Reply With Quote

Old   November 20, 2007, 06:25
Default Re: boundary layer specifications for laminar flow
  #3
Glenn Horrocks
Guest
 
Posts: n/a
Hi,

Laminar flows are strongly influenced by the boundary layer, but the boundary layer is much thicker than in turbulent flow so a coarser mesh can sometimes resolve it. Depends on exactly what Reynolds number you are at. Inflation layers are still useful until you are doing very low Reynolds numbers, ie Stokes flow.

Blood has strong non-newtonian properties so you may well need a fine boundary mesh to resolve these non-linear properties. I have never modelled blood so am no expert on it but you should check it out.

Glenn Horrocks
  Reply With Quote

Old   November 20, 2007, 08:50
Default Re: boundary layer specifications for laminar flow
  #4
Jim
Guest
 
Posts: n/a
If you assume for a moment that you have a constant viscosity (I know you haven't but go with it), then since the flow is laminar you basically have a Hagen-Poiseuille flow, i.e. a parabolic velocity profile. Therefore (IMHO) you should use a power law grid distribution so that you have equal increments of velocity across each cell. For example, if u_wall=0 and u_max=1 m/s, and you use 20 cells across the channel width, then each cell should be at the position that correlates to velocity profile increments of 0.1 m/s. This will give you the refinement you need at the walls. If you have problems understanding this rather wordy explanation, draw a parabola on some graph paper(y is position, x is velocity) and mark off the y positions that correlate with equal increments in x. Good luck.
  Reply With Quote

Old   November 21, 2007, 01:38
Default Re: boundary layer specifications for laminar flow
  #5
ranjith
Guest
 
Posts: n/a
Thank you Frank, Glenn & Jim for ur suggestions
  Reply With Quote

Old   October 13, 2017, 07:13
Default
  #6
New Member
 
Trudix
Join Date: Oct 2017
Location: Hamburg, Germany
Posts: 2
Rep Power: 0
Trudix is on a distinguished road
Hi guys, even though this post is pretty old allready, I have a similar question. I'm new to CFD and I'm trying to model a microchannel device. According to Glen Horrocks: "Inflation layers are still useful until you are doing very low Reynolds numbers, ie Stokes flow." To which magnitude of Re Inflation-layers make sense? Since I'm dealing with really low Re, should I just use my regular tedrahedron-mesh near the walls. Is a mesh refinement near the walls requiered? Thanks a lot for your help. It's very much appreciated.
Trudix is offline   Reply With Quote

Old   October 13, 2017, 17:59
Default
  #7
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 13,872
Rep Power: 107
ghorrocks is a jewel in the roughghorrocks is a jewel in the roughghorrocks is a jewel in the rough
You should consider why inflation layers are recommended in the first place. They are useful in high Re flows as the flow variables change rapidly in the boundary layer region and a fine mesh is required to capture this rapid change so the flow is accurate. So the mesh resolution you require depends on how rapidly the variables change.

For microfluidic devices you rarely get boundary layers forming and you are more likely to have laminar flow, possibly fully developed. In fully developed flow the variables change smoothly across the entire section - which means there is no rapid change near the wall, so no inflation layers are required. But a laminar flow which is not fully developed may require additional resolution at the wall to capture the start up behaviour.

As always, it is problem dependant. So do a mesh sensitivity study and find out in your case.
ghorrocks is offline   Reply With Quote

Old   October 16, 2017, 08:09
Default
  #8
New Member
 
Trudix
Join Date: Oct 2017
Location: Hamburg, Germany
Posts: 2
Rep Power: 0
Trudix is on a distinguished road
Thanks a lot for your help ghorrocks!
Trudix is offline   Reply With Quote

Reply

Thread Tools
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are On
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Wind turbine simulation Saturn CFX 45 February 8, 2016 05:42
Boundary Layer of Laminar Flow over a Flat Plate Blasius_Pohlhausen_Crocco Main CFD Forum 12 September 30, 2013 17:35
Boundary layer generation problems ivan_cozza OpenFOAM Native Meshers: snappyHexMesh and Others 0 October 6, 2010 13:47
Boundary layer strategy for port flow case? MaxCFM Main CFD Forum 1 September 9, 2009 06:09
Unsteady Boundary Layer Flow Wen Long Main CFD Forum 0 July 29, 2002 23:08


All times are GMT -4. The time now is 02:57.