|
[Sponsors] |
March 12, 2009, 06:32 |
heat resistance on solid-solid interface
|
#1 |
Guest
Posts: n/a
|
Dear CFX users!
My problem is the following: there are two solid bodies which are connected with solid-solid interface. There is heat generation (W/m3) in either of the solid domains. The thermal conductivity of the solids is different. I should define an additional heat transfer coefficient (4000 W/m2K) because the thermal contact is not perfect between them. I don't know how to define this htc on the domain interface. I found that I could set up source, where the Flux coefficient is the htc, but I don't know the value of the Flux. Does anybody could help me? Bela |
|
March 16, 2009, 15:31 |
|
#2 |
Member
Pratik Mehta
Join Date: Mar 2009
Posts: 32
Rep Power: 17 |
Hi, could you please explain what do you mean by thermal contact is not proper . What exactly is your problem set-up .
|
|
March 19, 2009, 04:55 |
|
#3 |
New Member
Join Date: Mar 2009
Posts: 5
Rep Power: 17 |
Thermal contact resistances are not supported in ANSYS CFX 11. There may be some way of representing such resistances with user defined code or CEL though - it might be worth contacting ANSYS directly for advice.
I was told by ANSYS that they will be supported (together with other surface physics enhancements) in CFX 12, but I haven't seen the Beta release of CFX 12 to check whether they actually made it to the actual product... Best regards, andy2o |
|
March 19, 2009, 09:53 |
|
#4 | |
Senior Member
Jack
Join Date: Mar 2009
Posts: 106
Rep Power: 16 |
You can use Fluent for solving this problem.
Quote:
|
||
March 19, 2009, 12:11 |
|
#5 |
Member
Pratik Mehta
Join Date: Mar 2009
Posts: 32
Rep Power: 17 |
Hi,
Is your problem a natural convection or forced convection , all I can for now think of is that , you can have model the improper contact between the two solids as a porous media ( separate porous domain) , this porous domain should be having all the flow resistances in 3 directions. I hope this helps cheers Pratik |
|
March 19, 2009, 18:43 |
|
#6 |
New Member
Join Date: Mar 2009
Posts: 5
Rep Power: 17 |
Pratik,
When two bodies are held together, the (perhaps large, or perhaps microscopic) roughness of the surfaces of the bodies means that they do not come into uniform perfect contact. There will be small gaps between them (often filled with air). Therefore for heat to flow from one body to another it has to cross this small gap by conduction, small scale convection, or radiation. This gives rise to thermal resistance. Because the gap is so small, you do not want to mesh it or model it as a 3-d feature. Instead, it is often modelled as a thermal resistance at a surface. Unfortunately CFX does not yet easily support this. This is what Bela was asking about. I hope it makes sense now. Best regards, andy2o |
|
March 20, 2009, 03:28 |
|
#7 |
Member
Pratik Mehta
Join Date: Mar 2009
Posts: 32
Rep Power: 17 |
Hi Andy ,
ok, now it is clear abt Bela`s query , you are right CFX till now have no such feature till now thanks andy best regards pratik |
|
October 25, 2022, 16:57 |
|
#8 |
New Member
Ubade Kemerli
Join Date: Feb 2016
Posts: 2
Rep Power: 0 |
Hi Bela,
I use fluent, and I don't know if you can do it at CFX, but what I do in fluent is that I add a wall thickness and define a material for that wall thickness. By doing that, you can have the same thermal resistance by defining the thickness and thermal conductivity of the material properly. Hope that helps. |
|
October 25, 2022, 17:02 |
|
#9 |
Senior Member
Join Date: Jun 2009
Posts: 1,875
Rep Power: 33 |
- Open the solid-solid domain interface
- Go to the Additional Interface Models tab - Select Heat Transfer/Interface Model option = Thin Material - Select Material name - Set material thickness.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. |
|
Thread Tools | Search this Thread |
Display Modes | |
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
Two-sided Wall Heat Transfer BC - No Separate Solid Mesh and No Heat Transfer Coeff | swahono | OpenFOAM Running, Solving & CFD | 10 | October 15, 2018 06:43 |
Constant velocity of the material | Sas | CFX | 15 | July 13, 2010 09:56 |
Convective Heat Transfer - Heat Exchanger | Mark | CFX | 6 | November 15, 2004 16:55 |
Conjugate Heat Transfer between fluid and solid | Li Yang | Main CFD Forum | 8 | March 27, 2004 12:05 |
Replace periodic by inlet-outlet pair | lego | CFX | 3 | November 5, 2002 21:09 |