CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > FLUENT

Turbulent Viscosity Ratio Limited not Vanished yet, but My Case Was Converged

Register Blogs Members List Search Today's Posts Mark Forums Read

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   May 22, 2016, 01:41
Default Turbulent Viscosity Ratio Limited not Vanished yet, but My Case Was Converged
  #1
New Member
 
Andi
Join Date: Jun 2015
Location: Indonesia
Posts: 17
Rep Power: 7
Andi_Didi is on a distinguished road
Hello there, I have questions
I ran simulation about flow across inlet duct HRSG with Fluent 6.3.26, with the parameters were :
1. Turbulence model : Realizable k-epsilon
2. Standard wall function
3. k-epsilon model : Turbulence Intensity (10%) and hydraulic diameter
4. Residual monitor : 10-4
5. Inlet : Velocity inlet
6. Outlet : Outflow
7. Using Energy Equation

and i built the superheater tube geometri in my simulation.





while I was running the simulation, there was warning about "turbulent viscosity ratio limited to viscosity ratio of 100000 in ..... cells."

But in 1000 iterations my case was converged and the warning was not vanished yet. Can somebody explain what's wrong in my simulation?
Is my result valid ?

I'd appreciate for your help
Thanks

Regards
Andi_Didi is offline   Reply With Quote

Old   May 22, 2016, 10:42
Default
  #2
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 4,026
Rep Power: 48
LuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura about
In general, the result is invalid and you need to fix the limited viscosity ratio.

Make a plot and look for regions where the turbulent viscosity is extremely high. That will tell you where you need to improve.

It could be your uniform velocity inlet.
LuckyTran is offline   Reply With Quote

Old   May 24, 2016, 16:40
Default
  #3
New Member
 
Andi
Join Date: Jun 2015
Location: Indonesia
Posts: 17
Rep Power: 7
Andi_Didi is on a distinguished road
Quote:
Originally Posted by LuckyTran View Post
In general, the result is invalid and you need to fix the limited viscosity ratio.

Make a plot and look for regions where the turbulent viscosity is extremely high. That will tell you where you need to improve.

It could be your uniform velocity inlet.
Thanks LuckyTran,

So, do i just refine the grid in that area?

The statement about "limited viscosity ratio" appear, is it only because of my mesh, or something else like wrong boundary condition at the inlet?
Andi_Didi is offline   Reply With Quote

Old   May 24, 2016, 19:39
Default
  #4
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 4,026
Rep Power: 48
LuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura about
It can and usually is caused by wrong inlet boundary conditions. i.e. a high uniform turbulence intensity applied to a uniform velocity inlet is non-physical.

It can be caused by the mesh if there are significantly skewed cells.
LuckyTran is offline   Reply With Quote

Old   May 25, 2016, 21:51
Default
  #5
New Member
 
Andi
Join Date: Jun 2015
Location: Indonesia
Posts: 17
Rep Power: 7
Andi_Didi is on a distinguished road
Quote:
Originally Posted by LuckyTran View Post
It can and usually is caused by wrong inlet boundary conditions. i.e. a high uniform turbulence intensity applied to a uniform velocity inlet is non-physical.

It can be caused by the mesh if there are significantly skewed cells.
i have checked my worst skewness, and it is 0.554523 , is that bad ?





If it was my wrong boundary conditions at the inlet, can you suggest me the right one ?
I have my turbulence intensity set by 10 % (from other paper) and i used hydraulic diameter which is the hydraulic diameter of the inlet, that is 3.1409 m.

Thanks for your help LuckyTran.
Andi_Didi is offline   Reply With Quote

Old   May 25, 2016, 22:29
Default
  #6
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 4,026
Rep Power: 48
LuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura about
The skewness seems okay so it's probably not the cause.

Check where the turbulent viscosity ratio is too high and determine where the problem is. Is it near the inlet? Is it near your walls or is it in the core?

Or maybe it is not near the inlet but clustered around your tubes.
LuckyTran is offline   Reply With Quote

Old   May 28, 2016, 02:20
Default
  #7
New Member
 
Andi
Join Date: Jun 2015
Location: Indonesia
Posts: 17
Rep Power: 7
Andi_Didi is on a distinguished road
Quote:
Originally Posted by LuckyTran View Post
The skewness seems okay so it's probably not the cause.

Check where the turbulent viscosity ratio is too high and determine where the problem is. Is it near the inlet? Is it near your walls or is it in the core?

Or maybe it is not near the inlet but clustered around your tubes.
The turbulence viscosity is highest at sudden expansion (exit of the duct). Is my mesh too rough at that area ?



And just curious, is there any case that turbulent viscosity ratio could really exceed 10^5 ?

Last edited by Andi_Didi; May 29, 2016 at 03:50.
Andi_Didi is offline   Reply With Quote

Old   May 29, 2016, 02:42
Default
  #8
Senior Member
 
Lucky Tran
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 4,026
Rep Power: 48
LuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura about
There are certainly skewed cells in that area. Anyway, you know what locations need improvement.

Turbulent viscosity ratio > 10^5 is extremely rare and will certainly never occur for practical scenarios. Maybe for superfluids, critical point transitions, or inside a black hole or something... Since you doing a HRSG, I'll say that it's nearly impossible to have that high a viscosity ratio.
LuckyTran is offline   Reply With Quote

Old   May 29, 2016, 03:41
Default
  #9
New Member
 
Andi
Join Date: Jun 2015
Location: Indonesia
Posts: 17
Rep Power: 7
Andi_Didi is on a distinguished road
Quote:
Originally Posted by LuckyTran View Post
There are certainly skewed cells in that area. Anyway, you know what locations need improvement.

Turbulent viscosity ratio > 10^5 is extremely rare and will certainly never occur for practical scenarios. Maybe for superfluids, critical point transitions, or inside a black hole or something... Since you doing a HRSG, I'll say that it's nearly impossible to have that high a viscosity ratio.
Black hole.. ? yeah right..

Ok then, thanks for your help. I really appreciate it.
Andi_Didi is offline   Reply With Quote

Old   June 10, 2016, 09:09
Default
  #10
New Member
 
Andi
Join Date: Jun 2015
Location: Indonesia
Posts: 17
Rep Power: 7
Andi_Didi is on a distinguished road
Quote:
Originally Posted by LuckyTran View Post
There are certainly skewed cells in that area. Anyway, you know what locations need improvement.

Turbulent viscosity ratio > 10^5 is extremely rare and will certainly never occur for practical scenarios. Maybe for superfluids, critical point transitions, or inside a black hole or something... Since you doing a HRSG, I'll say that it's nearly impossible to have that high a viscosity ratio.
Lucky Tran, sorry i forgot. In my simulation, i'm using standard wall function for my wall treatment, but i have tube (wall ) with heat transfer condition (conjugate HT). Can i just use standart wall function or i have to use the other else ?
Andi_Didi is offline   Reply With Quote

Reply

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
"turbulent viscosity limited to viscosity ratio" olivier FLUENT 11 October 10, 2015 05:49
Turbulent viscosity ratio Balaji FLUENT 5 May 27, 2014 03:47
turbulent viscosity limited to viscosity ratio of? mechfloeng FLUENT 4 February 6, 2014 12:45
Turbulent viscosity Limited to viscosity ratio Adrian FLUENT 12 September 21, 2011 04:22
Free surface boudary conditions with SOLA-VOF Fan Main CFD Forum 10 September 9, 2006 12:24


All times are GMT -4. The time now is 14:16.