CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > FLUENT

Converting wall into interior

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By kennyboy

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   May 22, 2017, 06:34
Default Converting wall into interior
  #1
New Member
 
Ken
Join Date: Dec 2015
Posts: 15
Rep Power: 9
kennyboy is on a distinguished road
Hi there

I cant seem to find a solution to this on the forum so I thought i will just create a new thread.

What happens is I have a geometry but I subdivided it into several parts. And so there will be interface boundaries within this geometry itself. After I defined all the relevant walls on ANSYS designModeler, done with the meshing and export the mesh into fluent, fluent identified several of the interface boundaries within the geometry as walls instead of interior.

So I tried to change it under the Boundary Conditions tab of fluent but it cannot work. The error message was like "cannot change wall-xxxx- to interior because adjacent cell threads are of different types".

So I thought I might have forgotten to form the sub divided parts into a single part but I already did (selected all the subdivided parts, right click, form new parts in designmodeler). And I even selected all of these parts to be fluid.

So I was hoping someone can enlighten me what could have went wrong? How can I change these inter-sub divided volumes' interfaces into interior?

Thank you!
kennyboy is offline   Reply With Quote

Old   May 22, 2017, 10:25
Default
  #2
Senior Member
 
Lucky
Join Date: Apr 2011
Location: Orlando, FL USA
Posts: 5,115
Rep Power: 60
LuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura aboutLuckyTran has a spectacular aura about
Probably you ended up with several cell zones. Check in the cell zone conditions to see how many zones you have there.

You cannot have an interior interface between different cell zones. Even if you specify them as the same type (all fluids) they are still distinct domains.

You can go back to the mesher and try to fix the settings or you can merge all the cell zones together using the commands in fluent. In /mesh/ in TUI and the mesh section in the GUI ribbon. It might be called something funny like fuse instead of merge.

Only after all the cell zones have been merged can you change to an interior type. You should also merge the redundant boundaries(the wall wall-shadow pairs) when you do this. I forget which order to do it in (either boundaries first then zones or zones then boundaries).
LuckyTran is offline   Reply With Quote

Old   May 23, 2017, 05:21
Default
  #3
New Member
 
Ken
Join Date: Dec 2015
Posts: 15
Rep Power: 9
kennyboy is on a distinguished road
Quote:
Originally Posted by LuckyTran View Post
Probably you ended up with several cell zones. Check in the cell zone conditions to see how many zones you have there.

You cannot have an interior interface between different cell zones. Even if you specify them as the same type (all fluids) they are still distinct domains.

You can go back to the mesher and try to fix the settings or you can merge all the cell zones together using the commands in fluent. In /mesh/ in TUI and the mesh section in the GUI ribbon. It might be called something funny like fuse instead of merge.

Only after all the cell zones have been merged can you change to an interior type. You should also merge the redundant boundaries(the wall wall-shadow pairs) when you do this. I forget which order to do it in (either boundaries first then zones or zones then boundaries).
Hi LuckyTran,

thanks for the advice. I tried to fuse them in fluent but it cannot be done and there is a message as follows: "Not fusing zone xx and xx, coupled zones."
kennyboy is offline   Reply With Quote

Old   June 29, 2017, 03:32
Default solved
  #4
New Member
 
Ken
Join Date: Dec 2015
Posts: 15
Rep Power: 9
kennyboy is on a distinguished road
ok managed to sovle my problem in the end. cos i cut my control volume into smaller sub-volumes (for structured meshing) and they are defined as separate parts. which explains why the inter-boundary surfaces are defined as walls (instead of interior) because fluent sees these sub volumes as separate entities.

so what i did was to 'form new parts' in designmodeler so all the sub volumes are now '1 part'. then my inter-boundary surfaces are all interior now.
Mly Rida likes this.
kennyboy is offline   Reply With Quote

Reply

Tags
boundary condition error, designmodeler, interior, mesh, wall

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
How to select 'Rotating Interior Wall' in COMSOL Davitt Main CFD Forum 5 January 16, 2017 15:20
Wrong flow in ratating domain problem Sanyo CFX 17 August 15, 2015 07:20
[Other] Convert a interior face into a wall be_inspired OpenFOAM Meshing & Mesh Conversion 1 January 24, 2012 05:41
[Commercial meshers] tmerge utility creates unwanted interface/walls comes in the final mesh Shoonya OpenFOAM Meshing & Mesh Conversion 11 January 20, 2012 07:23
wall..interior..interface mumdad FLUENT 1 June 6, 2008 06:50


All times are GMT -4. The time now is 06:58.