combining structured and unstructured grids

 Register Blogs Members List Search Today's Posts Mark Forums Read

 January 23, 2007, 10:37 combining structured and unstructured grids #1 Shane Guest   Posts: n/a Sponsored Links I am attempting to create a mesh for an entire aircraft and am looking at trying to combine both structured and unstructured grids into it. I am looking to use the unstructured grids around the intersections that also have complex curvature. Has anyone had any luck either creating a structured grid at any intersection; like between a wing and the fuselage of the aircraft; or has anyone successfully built a grid that involved structured and unstructured meshes?

 January 23, 2007, 12:00 Re: combining structured and unstructured grids #2 Razvan Guest   Posts: n/a Hi Shane, I am currently simulating DLR-F4 wing-body using several hybrid meshes of different densities. The technique I used is exactly the one you are talking about: employ unstructured surface mesh on almost all surfaces and structured in the most difficult regions (wing-body junction, leading and trailing edges). Then apply B-L mesh with 6-10 layers (y+ in wall functions range, over 30 and under 100), and fill the rest of the domain with unstructured tetrahedral mesh. Minimum mesh size for quantitative results is around 2 mill. elements, but for good results you must go over 5 millions (with at least 1 mill. elements in the B-L region only!). So the answer is: yes, you can make a quite good hybrid grid for aircraft-type geometries, but you must be very careful about mesh quality especially in the B-L region! Drag is particulary sensitive to near-wall mesh quality. All the best, Razvan

 January 23, 2007, 21:57 Re: combining structured and unstructured grids #3 zxaar Guest   Posts: n/a we also use meshes generated in parts. This is my workflow : [*] make the the meshes in parts such that the mesh on the sharing faces (with other blocks) is exactly same.[*] use tmerge to merge these meshes into one.[*] in fluent, there is a option Grid->Fuse, use this option to fuse the sharing faces of the mesh.[*] save the case[*] import the mesh from this saved case[*] export the final mesh to be used in simulation. hope this helps , you can avoid the gambit import and export again, for me i do this because this way the mesh is written as a single block, and i prefer that.

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post thomasduerr OpenFOAM Meshing & Mesh Conversion 20 March 13, 2017 07:07 user Main CFD Forum 6 November 25, 2010 02:14 Samir FLUENT 1 February 7, 2005 01:48 Samir FLUENT 0 February 5, 2005 22:21 phil FLUENT 0 March 5, 2003 07:00