
[Sponsors] 
Time step dependence of convergence behavior of steady state simulations in CFX 

LinkBack  Thread Tools  Display Modes 
April 21, 2011, 05:43 
Time step dependence of convergence behavior of steady state simulations in CFX

#1 
Senior Member
Join Date: Oct 2010
Location: Zurich
Posts: 176
Rep Power: 8 
I am simulating steady state turbulent conjugate heat transfer problem in CFX. I am facing some convergence problems (residuals stabilize before reaching convergence criteria). I have gone through the FAQ regarding this available under CFD wiki ( http://www.cfdonline.com/Wiki/Ansys...gence_criteria) and tried to play with the timestep being used by the CFX solver.
Now I observe the following 1) With Automatic Timestep calculation, I am able to get convergence for my simulations if I reduce the Timescale factor to 0.1. So whatever automatic timestep is calculated by solver, I multiply it with 0.1. 2) I tried to get an idea of the physical timestep by plotting streamlines and observing the time variable on the streamlines (as outlined in the CFD wiki link above). However, the flow is very complex consisting of 3dimensional vortices and the physical time estimate from streamlines is very large. And choosing a timestep based on a fraction (1/3 to 1/5) of this physical time leads to a large timestep and solver failure 3) Choosing the local timescale factor of 4 leads to very slow convergence. I have asked similar question before on this forum. However, I have come back as I am not sure what I am doing is right. My question is: a) Is it fine to get convergence by such large reduction (1/10) in the automatically calculated time step? I have repeatedly checked my mesh and setup and I have not been able to find any problem with that. I have also checked that I am not resolving any transient behavior in my simulation because the period of oscillation of residual changes with change in timestep. b) The transient formulation being used in CFX for steady state simulation is fully implicit (correct me if I am wrong). Then why does the convergence behavior depend on choice of timestep? Isn't a fully implicit discretization unconditionally stable? c) moreover, why should attainment of steady state depend on choice of timestep? Theoretically one can use as large a timestep as desired. 

April 25, 2011, 07:25 

#2 
Senior Member
Join Date: Oct 2010
Location: Zurich
Posts: 176
Rep Power: 8 
Anyone please...


April 25, 2011, 07:52 

#3 
New Member
Florent Duchaine
Join Date: Jan 2011
Location: Toulouse, France
Posts: 25
Rep Power: 8 
what is your configuration?


April 28, 2011, 18:39 

#4 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 13,437
Rep Power: 104 
a) You can use any time step you like to get convergence. A larger timestep will usually get there quicker, that is why it is recommended.
b) Yes, CFX is fully implicit (although there are some physics models which are not, such as surface tension and particle tracking, but that is another matter). The importance of time step size is that is what CFX uses to stabilise the equations. A SIMPLE based solver uses under relaxation factors. CFX uses time step size. c) Just as for under relaxation (URF) on SIMPLE based solvers, you want to use the largest URF which converges reliably. Then you often reduce it a bit for safety. Likewise in CFX you use the largest timestep which converges. As you approach convergence the equations often become more stable, meaning that you can increase the timestep size. This means it is very common to start a CFX steady state run with a small timestep and run that for a few iterations to set the flow up, but then start increasing the time step size as the flow settles down. As you approach convergence you can often be running time steps 100 or 1000 times larger than you started with. Use the "Edit run in progress" feature of the sovler manager and you can do this without stopping and restarting the run. 

May 3, 2011, 12:53 

#5  
Senior Member
Join Date: Oct 2010
Location: Zurich
Posts: 176
Rep Power: 8 
Quote:
I have one query here. In my simulations, I find that convergence stalls and when I reduce the timestep, it goes towards convergence. But when I reach near convergence I have to keep the time step small until the convergence is reached. This is because in one of the simulations I tried the following: 1. I first got a solution with reduced timestep. 2. Then used this as initial condition with a larger timestep. The residuals actually went up and stabilized at the higher level (inside the red circle)! Does this point to some error in problem setup? 

December 23, 2013, 06:31 
convergence problem

#6 
New Member
Bitte56
Join Date: Mar 2013
Location: India
Posts: 15
Rep Power: 6 
[QUOTE=ghorrocks;305513]a) You can use any time step you like to get convergence. A larger timestep will usually get there quicker, that is why it is recommended.
b) Yes, CFX is fully implicit (although there are some physics models which are not, such as surface tension and particle tracking, but that is another matter). The importance of time step size is that is what CFX uses to stabilise the equations. A SIMPLE based solver uses under relaxation factors. CFX uses time step size. c) Just as for under relaxation (URF) on SIMPLE based solvers, you want to use the largest URF which converges reliably. Then you often reduce it a bit for safety. Likewise in CFX you use the largest timestep which converges. As you approach convergence the equations often become more stable, meaning that you can increase the timestep size. This means it is very common to start a CFX steady state run with a small timestep and run that for a few iterations to set the flow up, but then start increasing the time step size as the flow settles down. As you approach convergence you can often be running time steps 100 or 1000 times larger than you started with. Use the "Edit run in progress" feature of the sovler manager and you can do this without stopping and restarting the run.[/ Sir, I am also having the convergence problem. I have attached image here. When i reduced time step, residuals actually went up. why? ] 

Tags 
cfx, convergence stall, steady state, time step 
Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Moving mesh  Niklas Wikstrom (Wikstrom)  OpenFOAM Running, Solving & CFD  122  June 15, 2014 06:20 
How to write k and epsilon before the abnormal end  xiuying  OpenFOAM Running, Solving & CFD  8  August 27, 2013 15:33 
Time step of steady particle tracking  payam_IUST  FLUENT  1  October 12, 2009 08:19 
false time step implementation for steady state  Kushagra  CFX  1  June 22, 2008 19:06 
Small time step and CFX solver crashing  Vanessa  CFX  2  June 21, 2006 09:18 