[fa123]

Hi everybody,

can anybody give me a hint about how one can get access to the type of the patches,
similar to

const labelList& patch1 = mesh.boundary()["inlet"].faceCells();

Here, I want just see the type of the patches instead, like "patch, wall, empty ...".

Thanx in advance.

[ahmmedshakil]

Just for a example:

  DynamicList<label> fluidCoupledTemperaturePatchIDs(Tf.boundaryField().size());
	DynamicList<label> fluidCoupledHeatFluxPatchIDs(Tf.boundaryField().size());
	forAll(Tf.boundaryField(), patchI) 
	{
		if(Tf.boundaryField()[patchI].type() == "regionCoupleTemperature")
		{
			fluidCoupledTemperaturePatchIDs.append(patchI);
		}
		else if(Tf.boundaryField()[patchI].type() == "regionCoupleHeatFlux")
		{
			fluidCoupledHeatFluxPatchIDs.append(patchI);
		}
	}

Originally Posted by fa123

Hi everybody,

can anybody give me a hint about how one can get access to the type of the patches,
similar to

const labelList& patch1 = mesh.boundary()["inlet"].faceCells();

Here, I want just see the type of the patches instead, like "patch, wall, empty ...".

Thanx in advance.

[fa123]

Thank you for the answer.

But i am looking for the base boundary type (patch, wall, empty, cyclic, symmetry ...).

I found the solution now.

      const polyBoundaryMesh& patches = mesh.boundaryMesh();

      forAll(patches, patchI)
      {
        const polyPatch& pp = patches[patchI];
       Info<< " type " << pp.type() << endl;
      }

[ChrisA]

Also might be helpful for you:

 	      	forAll(JTherm.boundaryField(),patchI)
 	      	{
 	      	 	if (isA<wallFvPatch>(mesh.boundary()[patchI]))
 	      	 	{

A snippet of a piece of code I used to set wall normal values manually to zero (since it couldn't be done through boundary conditions for the field in question and the model called for it)