CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > OpenFOAM > OpenFOAM Running, Solving & CFD

fanPressureJump BC with buoyantPimpleFoam

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree1Likes
  • 1 Post By charlesklewicki

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   June 12, 2020, 12:34
Default fanPressureJump BC with buoyantPimpleFoam
  #1
New Member
 
Join Date: Feb 2020
Posts: 2
Rep Power: 0
charlesklewicki is on a distinguished road
Hi all,

I'm currently working on a project to simulate heat transfer through air in a confined space between a heating element and an evaporator and I am having trouble implementing the fanPressureJump BC. So far I have been able to setup my mesh and now I am working on adding the fanPressureJump BC to represent the evaporator blower.

I have followed the TJunctionFan tutorial and I was able to modify the tutorial by adding my own custom mesh and I get reasonable results when running pimpleFoam. The issue I am having is that when I try to switch the solver to buoyantPimpleFoam in order to incorporate buoyancy effects the fanPressureJump BC seems to cease functioning. I used the hotRoom tutorial as a starting point for the constants, fvSolution, fvSchemes, and controlDict files. I have attached images of the U magnitude results after 0.3 s from pimpleFoam and buoyantPimpleFoam and I have also attached a zipped file of the case.

Any help is much appreciated.
Attached Images
File Type: jpg pimpleFoam.jpg (23.5 KB, 59 views)
File Type: jpg buoyantPimpleFoam.jpg (20.3 KB, 38 views)
Attached Files
File Type: zip podBaffle.zip (16.5 KB, 20 views)
charlesklewicki is offline   Reply With Quote

Old   June 15, 2020, 12:19
Default p_rgh
  #2
New Member
 
Join Date: Feb 2020
Posts: 2
Rep Power: 0
charlesklewicki is on a distinguished road
I was able to resolve this issue by applying the fanPressureJump BC on the p_rgh file instead of the p file.
esma likes this.
charlesklewicki is offline   Reply With Quote

Old   March 20, 2023, 03:38
Default
  #3
New Member
 
Join Date: Mar 2021
Posts: 7
Rep Power: 5
ShaneheSSSS is on a distinguished road
hello,I encounter this problem as well,do you mean applying fanPressureJump BC on the system/createBafflesDict as well as the 0/p_rgh file?

Thank you in advance!
ShaneheSSSS is offline   Reply With Quote

Old   October 17, 2024, 16:42
Default
  #4
Member
 
Join Date: May 2016
Posts: 40
Rep Power: 10
esma is on a distinguished road
I appreciate your feedback as it saved me.
I've been struggling with a cyclic patch for the fan to work in buoyantSimpleFoam.
after applying topoSet and createBaffle to produce the patch, the solver automatically assigns the pressure jump to "p" and not "p_rgh". I copied the cyclic patch from p to p_rgh and now is functioning.

p_rgh
----------
cyclicFaces_master
{
type fan;
patchType cyclic;
jump uniform 0;
value uniform 0;
jumpTable constant 15;
}
cyclicFaces_slave
{
type fan;
patchType cyclic;
value uniform 0;
}
esma is offline   Reply With Quote

Reply

Tags
buoyantpimplefoam, fanpressure

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
buoyantPimpleFoam vs. Oliveira and Issa paper MaryBau OpenFOAM 0 June 25, 2018 15:00
buoyantPimpleFoam high Courant numbers lcbuijs OpenFOAM Running, Solving & CFD 5 March 23, 2015 05:35
buoyantPimpleFoam with thermalBaffle1D: strange temperature decrease donQi OpenFOAM Running, Solving & CFD 0 July 14, 2014 21:30
buoyantPimpleFoam Convergence Issues joel.lehikoinen OpenFOAM 1 December 5, 2013 15:58
Questions about buoyantPimpleFoam and rhoPimpleFoam Mojtaba.a OpenFOAM Running, Solving & CFD 6 August 1, 2012 05:50


All times are GMT -4. The time now is 13:59.