[Dr T]

I am trying to use flow rates from an external file however OF keeps complaining about "values" keyword missing. The template according the documentation is

 <entryName> tableFile;  
   <entryName>Coeffs 

    { 
      dimensions          [0 0 1 0 0]; // optional dimensions        
     fileName            dataFile;    // name of data file         
     outOfBounds         clamp;       // optional out-of-bounds handling
     interpolationScheme linear;      // optional interpolation method  
     }

My usage:

 inlet
     {
        type                flowRateInletVelocity;
        volumetricFlowRate  tableFile;
        Coeffs
        {
            // dimensions          [0 0 1 0 0]; // optional dimensions
            fileName            dataFile;    // name of data file
            outOfBounds         clamp;       // optional out-of-bounds handling
            interpolationScheme linear;      // optional interpolation method

         }

The dataFile above contains time and flow rates in the following format

(
(0.0    0.005)
.
.
(0.5   0.02)
);

When I run with the above setup I get the "values" entry missing error.

keyword values is undefined in dictionary "foam/tableFile_test/0/U/boundaryField/inlet/volumetricFlowRateCoeffs"

However, I was able to run by using "table" instead of a "tableFile" which is of course quite ugly/inconvenient when pasting thousands of lines in the U bc file. I was also able to run with values pasted within U file with the tableFile entry but just not able to read the values from an external file. Also, renaming the "Coeffs" to "values" directly looks for integers within braces and still doesnt look for an external file. Looks like a possible bug. Appreciate any thoughts.

[Dr T]

ok, looks like I found the solution, and here is the modified version that works:

    inlet
    {
        type                flowRateInletVelocity;
        volumetricFlowRate  tableFile;
        volumetricFlowRateCoeffs
        {
            // dimensions          [0 0 1 0 0]; // optional dimensions
            file            "$FOAM_CASE/0/inflow";    // name of data file
           // fileName            "$FOAM_CASE/0/inflow";    // name of data file
            outOfBounds         clamp;       // optional out-of-bounds handling
            interpolationScheme linear;      // optional interpolation method

        }
           
    }

Not sure if this is a bug, but the TableFileReader.C is looking for a "file" entry whereas the docs mention it as "fileName". This is also crazy because the openfoam.org (V2112) requires a "file" entry and is exactly the same as above. Whereas openfoam.com(10) requires "fileName" but works with "file"!