CFD Online Logo CFD Online URL
Home > Forums > Software User Forums > OpenFOAM > OpenFOAM Running, Solving & CFD

LES of a turbulent channel flow stays laminar

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree4Likes
  • 2 Post By eelcovv
  • 2 Post By cedric_duprat

LinkBack Thread Tools Search this Thread Display Modes
Old   May 21, 2010, 10:46
Default LES of a turbulent channel flow stays laminar
Senior Member
Xiaofeng Liu
Join Date: Mar 2009
Location: State College, PA, USA
Posts: 118
Rep Power: 17
liu is on a distinguished road
Hi folks,

I am trying to reproduce the channel flow case as in Baba-Ahmadi and Tablor (Computers & Fluids, 38 (2009):1299-1311) titled:" Inlet conditions for LES using mapping and feedback control".

The wall bounded channel is 20mX2mX2m. I wrote a m4 script for the grid. It has 60 grids in X direction and 30 in Z direction. The grid in Y direction is graded towards the wall (grading = 10) with a total of 60 grids.

The inlet velocity BC is "directMapped" with an offset of 0.5m and average velocity of 0.1375 m/s. Viscosity = 1E-5, So Re=13,750 which is the same as in the paper.

Other setups: LESModel = oneEqEddy, delta = cubeRootVol
div(phi,U) = Gauss linear;
ddtScheme = backward,

deltaT = 0.1s for total of Time = 1000 s (which is about 6-7 flow through)

But the flow stays laminar. Maybe I should run the case longer, say 100 flow through time?

I have attached the case file. Please help me setup the case correctly. Thanks.
Attached Files
File Type: zip (11.8 KB, 36 views)
liu is offline   Reply With Quote

Old   May 27, 2010, 10:00
Default increase Re
Senior Member
Eelco van Vliet
Join Date: Mar 2009
Location: The Netherlands
Posts: 124
Rep Power: 19
eelcovv is on a distinguished road
Hi Liu,

I had the same problem with my channel. The problem is that the flow should first become unstable. If you start laminar you need to add some disturbance. The easiest way is to temporary decrease your viscosity (to say 1e-6 m2/s), run it until the flow shows turbulent structures, and then set it back to 1e-5 m2/s to set the correct Reynolds number.


zhutaihang and like this.
eelcovv is offline   Reply With Quote

Old   May 27, 2010, 13:53
Senior Member
Join Date: Mar 2009
Location: Nantes, France
Posts: 195
Rep Power: 17
cedric_duprat is on a distinguished road
Hi Liu,

If you don't want to change your viscosity and your Reynolds number, you can add perturbation before beginning your calculation (i.e. as initial condition).

To proceed, you can :
1- first have a look at the perturbU tool which is usefull to add artificial noise close to the wall (where gradients are high). (you can find details in Eugene de Villiers Ph'D thesis)
2- then run your calculation using channelOodles solver to reach a turbulent state (simple channel flow solver)
3- then change your boundary conditions to use directMappedFields one with an already turbulent flow.
4- enjoy you calculation

This is working fine

I hope this will help.

zhutaihang and like this.
cedric_duprat is offline   Reply With Quote


Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On

Similar Threads
Thread Thread Starter Forum Replies Last Post
CFX Treatment of Laminar and Turbulent Flows Jade M CFX 18 September 15, 2022 07:08
LES of turbulent channel flows cedric_duprat OpenFOAM Running, Solving & CFD 220 November 18, 2019 04:19
Using a turbulent model when the flow is entirely laminar. mwhyte FLUENT 1 June 7, 2012 10:35
Turbulent Flow in a Square Duct using LES Hock Ming FLUENT 0 February 7, 2009 20:25
LES turbulence decaying in channel flow cfdIsMad CFX 4 July 4, 2008 06:29

All times are GMT -4. The time now is 16:39.