|
[Sponsors] |
[ICEM] Is there a way to coarsen only a part of interior Hexa elements? |
|
LinkBack | Thread Tools | Search this Thread | Display Modes |
April 26, 2019, 15:10 |
Is there a way to coarsen only a part of interior Hexa elements?
|
#1 |
New Member
Join Date: Apr 2019
Posts: 7
Rep Power: 7 |
Hello everyone,
I have used blocking ogrid to create a mesh for a cylinder, consisting of hexa and quad elements only. Since there are many curves on the surface (wall) of my geometry, I chose a great number for edge nodes to make the mesh follow the geometry properly. However, I don't need these fine elements deep inside the interior of the volume, leading to my question: Is there a way to only coarsen (somehow combine) inside hexa elements to reduce computation time and cost, while keeping them finer on the way to near the surface? Any help would be greatly appreciated. Hexa.PNG |
|
April 29, 2019, 14:07 |
|
#2 | |
Senior Member
Sebastian Engel
Join Date: Jun 2011
Location: Germany
Posts: 566
Rep Power: 20 |
Hi atafiroozi,
Quote:
Therefore a more complex blocking would be my suggestion which leaves fewer projections from the edge to the center. There is a technique called nesting, or clamping - basically an internal c-grid - to map 1 edge onto 3 edges. You might find more information here: http://blog.gridpro.com/nesting/ In your case you'd need to create a blocking such as the following drawing. Starting from you current o-grid, you'd need to insert a c-grid in each quadrant separately, as indicated in the drawing. pipemesh.jpg Of course this blocking will need some attention and testing on vertices positions to get good cell qualities. Best regards, Sebastian |
||
April 30, 2019, 11:21 |
|
#3 | |
New Member
Join Date: Apr 2019
Posts: 7
Rep Power: 7 |
Hi Sebastian,
Thanks for your reply. Quote:
I mean I couldn't find related command option, is it under the "Split Block" menu? Would you elaborate on using this method in ICEM? Thanks in advance. |
||
April 30, 2019, 13:16 |
|
#4 |
Senior Member
Sebastian Engel
Join Date: Jun 2011
Location: Germany
Posts: 566
Rep Power: 20 |
Well, you have used the o-grid tool at least once to create your initially shown mesh, did you? Are you confused with the term "c-grid"? A c-grid is just a quarter of an o-grid. It's used in cases where the "o"-layer is not a closed loop anymore. However, you can create it with the o-grid tool, too.
The key idea of the o-grid tool is, that you selection determines which edges/faces are to be extruded into blocks of the o-grid. If your mesh is 2D you'd need to create 4 additional o-grid, each being a c-grid in its respective quadrant. Each of these o-grid is created by selecting the one block of the respective quadrant. Deselect any other automatically added blocks. Then, add the circumferential edge to the selection. That way, each edge but the outer will be extruded inside, leaving you with a c-grid. In 3D you need to select the top and bottom face of that quadrant prism to prevent them from extruding. I strongly suggest you to have a read of the sticky thread in this subforum Before you start a thread, see if you can find answers here You'll find a guide called Simon's Tips & Tricks. Page 76 and following will be most interesting for you. Best regards, Sebastian |
|
April 30, 2019, 15:51 |
|
#5 |
Super Moderator
|
CGrid is OGrid, when you select one face or edge. The meshing shape will look C
|
|
May 1, 2019, 13:10 |
|
#6 | ||
New Member
Join Date: Apr 2019
Posts: 7
Rep Power: 7 |
Quote:
Quote:
My case is 3D and I've chosen these three faces: Faces.PNG After creating one c-grid in upper quadrant pre-mesh looks like this, which is not desired: UpperCgrid.PNG Actually what I want is to unlink these two edges shown between arrows, in order to give them each independent node numbers (concentrated mesh in upper edge and coarse mesh in near-core one): Edge.png Now I know this is a job for so-called c-grid, but I couldn't find the right way to do this so far. It would be wonderful if you'd guide me further on doing this. |
|||
May 3, 2019, 05:47 |
|
#7 | ||
Senior Member
Sebastian Engel
Join Date: Jun 2011
Location: Germany
Posts: 566
Rep Power: 20 |
Quote:
From my point of view, this is exactly the structure i suggested. It seems, you just haven't moved any vertices jet. Make the c-layer blocks as big as its enclosed block. Then assess again. Quote:
If this gets to complicated to you, you might should think about a swept mesh. A swept block has a top (and bottom) face which are meshed unstructuredly. This top face mesh will then be extruded in layers to fill the block. For example use a all quad face with really independent edge counts. You'll probably still have a structured mesh in flow direction. |
|||
May 5, 2019, 08:36 |
|
#8 | |
New Member
Join Date: Apr 2019
Posts: 7
Rep Power: 7 |
Quote:
Your comments were helpful. |
||
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
3D Windturbine simulation in SU2 | k.vimalakanthan | SU2 | 15 | October 12, 2023 05:53 |
2D Mesh of Line Elements - Possible? | adjpayot | SU2 | 1 | February 24, 2018 12:58 |
[ICEM] Negative Volume Elements Fix | mickyB | ANSYS Meshing & Geometry | 4 | March 15, 2016 00:15 |
Error Messages: Self intersecting faces, Solid Part is not closed, Floating point. | bigtoasty | STAR-CCM+ | 1 | March 4, 2016 05:05 |
Selecting the faces of part body after Enclosure and boolean operations | Amar21 | FLUENT | 6 | November 19, 2015 10:23 |