CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > Software User Forums > ANSYS > CFX

Impact of many (hundreds) of GGI on simulation speed

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree2Likes
  • 2 Post By ghorrocks

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   March 25, 2015, 08:48
Question Impact of many (hundreds) of GGI on simulation speed
  #1
New Member
 
Daniel Wilde
Join Date: Jan 2014
Posts: 21
Rep Power: 12
QCFD is on a distinguished road
Hello,

I am working with a simulation that involves a repeating pattern of fluid passages in a solid, think of it as a heat exchanger. This pattern repeats ~50x and there are 2 different fluid and solid zones per layer (2 solid zones cause there are different material properties) which led me to set up the problem with interfaces which include as many as 100 2-d mesh zones on a side.

My mesh count is well below what I have run in the past on the hardware I am using, but I am having issues where simulation startup (after partitioner but before 1st iteration) takes about 6 hours, hung at the same spot... which is many times more than I am used to, even for meshes with 2x as many volume elements.

Once the problem starts iterating, it runs quickly enough assuming it doesn't crash.

Is anyone familiar with what CFX has to do between partitioning and solving on GGI (there are no outputs in the .out file for the 6 hour period after partitioning).

Additionally, does anyone have suggestions for a better setup of a model with a large number of zones?

Note: all my solid-solid interfaces are conformal, fluid-solid are not.

I know that was long winded, but thanks in advance for your input
QCFD is offline   Reply With Quote

Old   March 25, 2015, 19:06
Default
  #2
Super Moderator
 
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,864
Rep Power: 144
ghorrocks is just really niceghorrocks is just really niceghorrocks is just really niceghorrocks is just really nice
You will need to change some defaults to get something like this to work.

* In solver manager, turn on coupled partitioning. This may fix the problem by itself.
* For the conformal interfaces, consider making them 1:1 rather than GGI.
* You may need to increase stack sizes in the partitioner or solver - it will tell you if you need to do this.
flotus1 and QCFD like this.
ghorrocks is offline   Reply With Quote

Old   March 25, 2015, 19:13
Default
  #3
New Member
 
Daniel Wilde
Join Date: Jan 2014
Posts: 21
Rep Power: 12
QCFD is on a distinguished road
Quote:
Originally Posted by ghorrocks View Post
You will need to change some defaults to get something like this to work.

* In solver manager, turn on coupled partitioning. This may fix the problem by itself.
* For the conformal interfaces, consider making them 1:1 rather than GGI.
* You may need to increase stack sizes in the partitioner or solver - it will tell you if you need to do this.
I was reading documentation today and came across information about the coupled partitioner. enabling coupled partitioner seems to have fixed the problem (my simulation is also way more stable using this setup)

As for the memory stacks, I had to play with those just to get to the point I am at now, but it was definitely needed to run the model.

Another thing I tried which reduced the startup time of the problem is user specified direction partitioner. my overlap percentages are worse, but the model started up quite a bit faster. *Note: this model seems to take more iterations to converge vs. an identical run using R.C.B. I suspect the flow of information has been biased by adding partition boundaries all in one direction along the model but this is just a guess based on what I am seeing

I do not have CFX pre up at the moment but I seem to remember I could only set 1:1 as the connection type if the volume elements on either side of the interface are in the same domain. I will check tomorrow and see if I can switch that since it should only help.
* Note: I just checked and 1:1 is definitely selectible in my case... not sure where I got this idea (disregard it)

Thanks for the input

Last edited by QCFD; March 26, 2015 at 10:18. Reason: new information
QCFD is offline   Reply With Quote

Reply

Tags
ggi, solver

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Resistance Simulation for High Speed Hull in Turbulence to Match Experimental Data PeiSan Fidelity CFD 0 September 3, 2014 01:08
Improving the speed of simulation Mark H Hardware 1 October 25, 2012 12:58
Improving model simulation speed Mark H Main CFD Forum 0 October 24, 2012 07:35
drop impact simulation bhaskar Main CFD Forum 0 February 24, 2007 06:49
Impact simulation of container filled with fluid worasit CFX 0 April 21, 2004 14:53


All times are GMT -4. The time now is 16:04.