|
[Sponsors] |
April 30, 2019, 08:30 |
Oddities in CFX
|
#1 |
New Member
Valera
Join Date: Dec 2018
Posts: 27
Rep Power: 7 |
Hi everyone!
My problem is as follows: I modelate a pipe counter heat exchager. It includes a lot of pipes, so I've decided to consider one elementary cell (even its quater) - see first 2 picture. So hot water (a coolant) flows into one side within pipe (without phase change), and the cold water flows from the other side in shell side, where it starts boiling. All parallel the pipe axis planes have symmetry BC. Inlet BC: inlet velocity outlet BC: outlet pressure (for both medium) After I got a decision, I saw a really strange oddity: The tempreture of water for both medium doesn't change at the start of flowing. You can see a little plateau in the both charts. Of course it desagrees the real situation. Maybe somebody knows what is it? (The solver did about 1500 itarations and the residuals stopped changing after 500-700 itarations). |
|
April 30, 2019, 08:51 |
|
#2 |
Senior Member
Join Date: Jun 2009
Posts: 1,804
Rep Power: 32 |
You only mentioned the residuals are not changing anymore.
No changing residuals do not mean the solution has converged yet. Level of the residuals matters considerably. You have not explained how is your mesh setup. The snapshot seems coarse on the boundaries. |
|
April 30, 2019, 09:43 |
|
#3 |
New Member
Valera
Join Date: Dec 2018
Posts: 27
Rep Power: 7 |
I tried to decriase the size of cells, but nothing change. I think the problem isn't in the mesh. Cells seem long in mesh, but aspect ratio quite good (average less than 10)
The maximum level of residual is as follows: (all other residuals a little smaller) They are not very small. I think it because I didn't turn double precision on (my computer can't even start solving with double precision) |
|
April 30, 2019, 09:49 |
|
#4 |
Senior Member
Join Date: Jun 2009
Posts: 1,804
Rep Power: 32 |
What about momentum/continuity/energy residuals?
|
|
April 30, 2019, 10:35 |
|
#5 |
New Member
Valera
Join Date: Dec 2018
Posts: 27
Rep Power: 7 |
Okey. They are:
|
|
April 30, 2019, 14:29 |
|
#6 |
Senior Member
Erik
Join Date: Feb 2011
Location: Earth (Land portion)
Posts: 1,167
Rep Power: 23 |
I'm guessing the heat has not reached you line yet (radially). You define an inlet temperature, and it takes time (distance) for that heat to reach an area away from the wall. I would expect these plateaus, and they will get smaller if you move you lines closer to the wall.
Last edited by evcelica; May 1, 2019 at 06:23. |
|
April 30, 2019, 14:57 |
|
#7 | |
New Member
Valera
Join Date: Dec 2018
Posts: 27
Rep Power: 7 |
Quote:
If I do some more iterations, will it help? |
||
April 30, 2019, 18:52 |
|
#8 |
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,703
Rep Power: 143 |
It is recommended for CHT simulations like this you add imbalances as a convergence criteria. You can also look at the imbalances in the solver manager to see if it has reached steady state - imbalances of around 1% are the usual target.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. |
|
April 30, 2019, 22:53 |
|
#9 |
Senior Member
Join Date: Jun 2009
Posts: 1,804
Rep Power: 32 |
May I ask why is the plateau incorrect?
What is your inlet velocity profile? if you start with the uniform flow, i.e. plug flow, the flow must develop and it will take a while (length along the pipe, not time) before the center line is heated. See "entrance length" in wikipedia, or a textbook for details. Similarly, there is the thermal entrance length For flow in a circular pipe, the thermal entrance length is approximately x/D = 0.05 * Re * Pr for laminar flow, and about 5-10 diameters for turbulent flow if I recall correctly. |
|
May 1, 2019, 05:48 |
|
#10 |
Senior Member
Erik
Join Date: Feb 2011
Location: Earth (Land portion)
Posts: 1,167
Rep Power: 23 |
There is no error here. That is the correct result.
Apparently I wasn't clear in my explanation the first time. |
|
May 1, 2019, 06:00 |
|
#11 |
New Member
Valera
Join Date: Dec 2018
Posts: 27
Rep Power: 7 |
Wow. Thank you for your thoughts. I haven't ever knew and thought about thermal entrance length existence, though I know about velocity entrance length.
But It sounds sanely. For example, if we consider h+(v^2)/2=const (I don't know how this equation is called in English; maybe "Bernoulli integral in the heat form"), we'll see, If velocity doesn't change, than h=const, or the same, t=const. It's only my thoughts (I don't know how they far from truth). The main thing is that the average tempreture is changed along pipe in this region. If I change inlet BC from velocity inlet to mass flow rate inlet, then velocity profile won't be uniform, isn't it? |
|
May 1, 2019, 08:24 |
|
#12 |
Senior Member
Erik
Join Date: Feb 2011
Location: Earth (Land portion)
Posts: 1,167
Rep Power: 23 |
Velocity and mass flow rate are both uniform inlets.
|
|
|
|
Similar Threads | ||||
Thread | Thread Starter | Forum | Replies | Last Post |
CFX Treatment of Laminar and Turbulent Flows | Jade M | CFX | 18 | September 15, 2022 07:08 |
High Resolution (CFX) vs 2nd Order Upwind (Fluent) | gravis | ANSYS | 3 | March 24, 2011 02:43 |
CFX pressure in Simulations problem | nasdak | CFX | 1 | April 14, 2010 13:22 |
PhD using CFX | Rui | CFX | 9 | May 28, 2007 05:59 |
FSI using CFX and ANSYS | Bi Chang | CFX | 2 | May 10, 2005 04:47 |