
[Sponsors] 
February 25, 2020, 01:44 
Scaled EulerLagrange Simulation

#1 
New Member
Terry Jeffords
Join Date: Feb 2020
Posts: 3
Rep Power: 4 
Hey simulation comissioners,
I am trying to simulate a particle flow out of a pressure vessel using the EulerLagrange method. To optimise the calculation time I am trying to scale the Navier Stokes equations, which should result in a system of dimensionless equations. To consider the momentum loss of the continuous phase (air) due to the high particle mass load of circa 1 kg particles / 1 kg air, I am using the fully coupled model. This adds an additional source term in the momentum equation of air. In the CFX solver theory guide (see chapter 6.2) is written, that the new source can be expressed by: dS=F_D dt Where F_D is the drag force defnined by: F_D=0.5 c_D rho_f A_f u_s u_s When you multiply this source with the particle number rate (necessary after the theory guide) it has the entity [kg m/s²]. But in fact it should be [kg /m² s] to fit with the other terms in the NSequation. So it has to be volume specific. But I got no clue how to solve this problem. Did anybody before tryed to simulate a particle flow dimensionless? I am pleased if you could help me. Best regards Terry Jeffords 

February 25, 2020, 16:45 

#2 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,170
Rep Power: 134 
Why are you adding this source term? The fully coupled particle model already has it included. Why do you want to include it twice?
With particle loads as high as you describe the Lagrangian particle model does not sound suitable. Wouldn't a Eularian particle model be more appropriate? Finally, CFX is a dimensional solver, so most people run it normal unit systems like m/s/kg. You can nondimensionalise it, for simple single phase flows that is simple enough but it starts getting complex when you have complex models like a multiphase model to nondimensionalise. Why nondimensionalise your simulation? Were you getting problems when you ran it as a dimensional solver?
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. 

February 26, 2020, 01:55 

#3 
New Member
Terry Jeffords
Join Date: Feb 2020
Posts: 3
Rep Power: 4 
Hello Glenn,
this source term is added to the Navier Stokes equations if you want to capture the momentum loss of the continuous phase due to the high particle mass load. Otherwise it would not be physically correct. And I do not want to add this source term twice I just want to add a coefficient to it to make the whole equation dimensionless. Well the problem is, that even though the mass fraction is high, the volume fraction is low with circa 1E4 m³ particle / m³ air. So mass fraction is important for the momentum coupling and the volume fraction is important for the decision of EulerEuler oder EulerLagrange. And I am not sure if Euler Euler works with such low volume fractions. What do you think? Well I am getting no problems when running it dimensional, but some guys in literature down in their rabbid holes said the accuracy raises and computational effort decreases if you numerically solve something dimensionless. But so far the only thing I see is that the human effort raises ^^ Thank you very much so far 

February 26, 2020, 03:48 

#4 
Senior Member
GertJan
Join Date: Oct 2012
Location: Europe
Posts: 1,568
Rep Power: 23 
With this small amount of volume fraction, I would opt for Lagrangian. However, the choice for Lagrange or Euler also depends on the question that you want to answer when doing CFD. What do you want to get out of it? E.g., if you have a size distribution, and want to know where goes what, then Lagrangian is easier to customize and to get the relevant data out of the simulation.


February 26, 2020, 05:15 

#5  
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 17,170
Rep Power: 134 
So you are trying to nondimensionalise the builtin particle to fluid coupling force? Is that correct? Yes, this is going to be challenging. I would do a literature search to see how other researchers have nondimensionalised multiphase flows. It is not trivial to do this, and there are likely to be several ways you can do it. I am not familiar with them, but I have studied works which nondimensionalised thermal convection and that was complex enough (let alone trying to convince a dimensional solver to act in a nondimensional way).
The mass fraction of particle is high but the volume fraction is low  OK. There are other factors in deciding Langrangian or Eularian. Lagrangian gives the precise track of a sample of particles, Eularian has many more models available to it (particle collison, wall lubrication, fluidised bed and many more  Lagrangian models don't have these options). Lagrangian models are only applicable to low particle volume fractions, but Eularian models can handle volume fractions from 0 to much higher. Quote:
In other words, unless you know you are getting round off errors the nondimensionalisation you propose is unlikely to help in CFX. If you are writing your own code then nondimensionalisation is one of the easiest ways to keep round off errors down  I suspect that is what the papers you are reading have in mind.
__________________
Note: I do not answer CFD questions by PM. CFD questions should be posted on the forum. 

Tags 
dimensionless, drag coefficient, eulerlagrange, particle, scaled 
Thread Tools  Search this Thread 
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
Control simulation to apply different fields with chtMultiRegionFoam  jmdf  OpenFOAM Running, Solving & CFD  0  February 29, 2016 07:05 
Segmentation fault during gust simulation  Oshin  SU2  3  February 16, 2016 11:03 
Euler Lagrange Convergence Tips  snpradeep  CFX  2  May 6, 2013 07:15 
EULER simulation  Alexandre  FLUENT  4  November 24, 2005 14:01 
3D Contaminant Dispersal Simulation  Apple L S Chan  Main CFD Forum  1  December 23, 1998 10:06 