
[Sponsors] 
September 30, 2010, 10:56 
inflation layer

#1 
Senior Member
Join Date: Jan 2010
Posts: 110
Rep Power: 9 
Sponsored Links
I am modeling a free surface flow. In order to correct predict the boundary layer I have put some inflation layers in the bottom zone. In order to "predict" the minimum required space between the nodes in the bottom of my mesh I have used the following expression: delta y= L (length of the domain)*y+*(80)^0.5 *Re^(13/14). I have set the value of y+ to 30 and then computed the value of delta y. I am using kepsilon turbulence model.Is this the correct procedure? Any suggestion will be very helpful.Regards 

Sponsored Links 
September 30, 2010, 18:26 

#2 
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 13,738
Rep Power: 106 
The ke model is best suited to wall functions, so you won't be modelling the full boundary layer. If your mesh is around y+=30 then this is probably a valid approach. If you want to model the full boundary layer you should consider some other turbulence models which integrate to the wall, SST is probably the best bet here. You will need to go to about y+=1 to get the full boundary layer this way, and that may be excessive for what you want to do. Up to you.


September 30, 2010, 21:16 

#3 
Senior Member
Joshua Counsil
Join Date: Jul 2009
Location: Halifax, Nova Scotia, Canada
Posts: 366
Rep Power: 11 
I seem to recall reading that modeling the boundary layer with the ke model requires a resolution of y+ < 0.2, which is ridiculous.


October 1, 2010, 04:48 

#4 
Senior Member
Join Date: Jan 2010
Posts: 110
Rep Power: 9 
Thanks a lot for your comments Mr.Glenn and Mr.Joshua.
If possible I would also like to clarify an additional aspect. As I have already said in order to predict the minimum required space between the nodes in the bottom I have defined y+ equal to 30 and then computed by hand the value of delta y. Then I have defined five inflation layers with this length (in my mesh). My solution converges (imbalance=0.01 and residuals=10^5). However in cfd post when I plot the yplus variable in the bottom wall it says that min value is 0 and the max value is 3.33. What can I conclude? Simply that I have an over refined mesh in the bottom zone correct?Typically it should be something like 20<y+<100 right? 

October 1, 2010, 05:32 

#5 
Member
Scott
Join Date: Sep 2009
Posts: 41
Rep Power: 9 
Hi Antonio,
This would be a valid solution. CFX will not have used the mesh close to the wall as it uses a wall function approach. You could try this same mesh with the Shear Stress Transport model which blends from ke in the freestream to kw at the walls. You need to remember that the equation that you used t approximate Y+ is for flow along a flat plate and that it is just a starting point for your y+ study. As y+ varies with velocity you will likely get a range of Y+ on any surface. As long as this is below 100 with ke then you are ok, but if you want to predict separation points or recirculation then you need to be very close to 1. Hope this helps a bit, Scott 

October 1, 2010, 06:18 

#6  
Super Moderator
Glenn Horrocks
Join Date: Mar 2009
Location: Sydney, Australia
Posts: 13,738
Rep Power: 106 
Quote:
Quote:
Quote:
Quote:


October 1, 2010, 18:21 

#7 
Member
Scott
Join Date: Sep 2009
Posts: 41
Rep Power: 9 
Hi Glenn,
I was trying to say that using a y+ of 3 for a ke mesh is a bit of a waste as ke will not resolve all of the way to the wall. Your comments are correct, of course it will calculate at the additional cells, but this may lead to erroneous solutions. As far as my comments for using SST. I am implying that the current mesh, having a y+~1 would be better suited to SST. If the user does not want the additional cells, then they could remesh with a y+~30 and run with ke. My suggestion was to not spend time remeshing, but to just switch to SST and rerun which is likely to be more accurate for wall bounded flows anyway. My comments regarding a Y+ of 1 to capture separation were specific to someone already using the SST model. As you said, the solution will gain accuracy with increased mesh resolution and for accurate separation prediction it is bette to resolve the boundary layer to the wall than rely on wall functions. Hope this clarifies things! We have the same position on this, you just got the point across better! Cheers, Scott 

Thread Tools  
Display Modes  


Similar Threads  
Thread  Thread Starter  Forum  Replies  Last Post 
[ANSYS Meshing] inflation layer issue on Ansys 12.0  IvanCFD  ANSYS Meshing & Geometry  11  April 8, 2014 05:54 
sample interpolation error in inflation layer  eelcovv  OpenFOAM Bugs  2  July 28, 2009 17:20 
Inflation layers / boundary layer meshing.  andy2o  Main CFD Forum  3  February 22, 2009 10:03 
2d axysymmetric inflation layer  justin  CFX  5  April 12, 2007 08:28 
errors  Fahad  Main CFD Forum  0  March 23, 2004 14:20 
Sponsored Links 