# Grid Independent Solution

 Register Blogs Members List Search Today's Posts Mark Forums Read

 July 13, 2000, 14:29 Grid Independent Solution #1 Chuck Leakeas Guest   Posts: n/a Hello all! I was just wondering about finding the grid independent solution for a chemically reacting flow. I have been performing many mesh refinements near a reacting surface and so far the deposition rate there keeps changing a great deal. Is it possible for there not to be a grid independent solution for certain problems? If so, how would one determine when a solution is 'good enough'? Thanks, Chuck

 July 14, 2000, 00:39 Re: Grid Independent Solution #2 John C. Chien Guest   Posts: n/a (1). If you are tired of cfd, you can try the control volume approach. (2). Just create one control volume, then model the flow and reaction, then you should have a simple mesh independent solution. (3). It is easier to understand the need of grid independent solution based on the finite-difference approach. This is because as the mesh size approach zero, the algebraic equations will approximate the real governing equations. (4). So, if the mesh is of finite size, it is likely that you are not solving the real governing equations, thus, not solving the real problem. (5). The number of mesh points needed depend on the solution profile distribution, the algorithm used. So, lower-order algorithms most of the time require more mesh points. Higher Reynolds number flows, wall boundary layer flows, flows with chemical reactions, requires both the mesh points and local mesh refinement.

 July 14, 2000, 10:18 Re: Grid Independent Solution #3 Chuck Leakeas Guest   Posts: n/a John, Does this mean a grid independent solution always exists no matter what method one uses? I am already using the FV method and I move the first grid point next to the wafer surface closer by one-half the distance for each new grid refinement. Is this a reasonable way to find the grid independent solution? Thanks, Chuck

 July 14, 2000, 11:16 Re: Grid Independent Solution #4 John C. Chien Guest   Posts: n/a (1). Yes, unless the model or the boundary conditions are explicit function of the mesh spacing (such as the wall function), you should be able to get the grid independent solution. (2). Run a calculation, plot the result, identify the high gradient areas, put more mesh points in those high gradient areas, re-run the case, check the result and compare the difference. When you no longer see the difference, you can stop. (that depends on the requirement, the difference between the acceptable solution and the real solution. It is one way to guarantee the solution is repeatable , within certain limit.)

 July 15, 2000, 03:27 Re: Grid Independent Solution #5 Duane Baker Guest   Posts: n/a Hi, what are you using for the advection term discretization? If you are using a really bad scheme such as first order UDS, the error reduction with grid refinement is so slow for some problems that it does seem to never get to a grid-independant solution. With Richardson extrapolatinon you can estimate the discretization error. Say for example, a 3D problem with UDS and reasonable but coarse grid of 50 cells in each direction gives a discretization error of 20%. Then doubling the grid will take the following sequence (if we are in the assymptotic convergence region): Grid Cells Total Cells Error 1 50x50x50 125000 20% 2 100x100x100 1000000 10% 3 200x200x200 8000000 5% etc. So, with most people's resources you will never see a grid independant solution before you are tapped out. As Ferziger and Peric state: UDS is inaccurate and should not be used. May I suggest that you read up on this issue in Ferziger and Peric's text: Computational Methods for Fluid Dynamcis. Regards..........Duane

 Thread Tools Display Modes Linear Mode

 Posting Rules You may not post new threads You may not post replies You may not post attachments You may not edit your posts BB code is On Smilies are On [IMG] code is On HTML code is OffTrackbacks are On Pingbacks are On Refbacks are On Forum Rules

 Similar Threads Thread Thread Starter Forum Replies Last Post gueynard a. Main CFD Forum 19 June 27, 2014 21:22 msv_kk STAR-CCM+ 2 August 7, 2011 15:54 jamesproctor Main CFD Forum 0 July 30, 2010 15:31 Armin Gips FLUENT 2 August 13, 2001 10:35 Chuck Leakeas Main CFD Forum 2 May 26, 2000 11:18

All times are GMT -4. The time now is 08:25.