CFD Online Logo CFD Online URL
www.cfd-online.com
[Sponsors]
Home > Forums > General Forums > Structural Mechanics

Ansys Mechanical Revolute Joint Retrict Rotation to One Direction

Register Blogs Members List Search Today's Posts Mark Forums Read

Like Tree2Likes
  • 1 Post By siw
  • 1 Post By siw

Reply
 
LinkBack Thread Tools Search this Thread Display Modes
Old   June 25, 2023, 19:09
Post Ansys Mechanical Revolute Joint Retrict Rotation to One Direction
  #1
New Member
 
RodrigoNeg
Join Date: May 2023
Posts: 7
Rep Power: 3
RodrigoNeg is on a distinguished road
Hi
In Ansys Mechanical how can I make a revolute joint that only spins in one direction? Specifically, I have a crankshaft and if it receives a force that would move the joint counterclockwise, I want the joint to not allow the movement, but if the force is in the clockwise direction it should move.
Thanks
RodrigoNeg is offline   Reply With Quote

Old   June 26, 2023, 05:42
Default
  #2
siw
Senior Member
 
Stuart
Join Date: Jul 2009
Location: Portsmouth, England
Posts: 739
Rep Power: 26
siw will become famous soon enough
I've not tried this but here goes: maybe since the Revolute Joint has UX, UY, UZ, ROTX and ROTY as fixed and ROTZ as free you could use a Bushing Joint and for ROTZ use the Tabular to input a non-linear angle-moment curve that has very low angular stiffness in the direction you want (e.g. positive angle direction) rotation and very high angular stiffness in the direction you want no rotation (e.g. negative angle direction).
RodrigoNeg likes this.
siw is offline   Reply With Quote

Old   July 5, 2023, 18:05
Default
  #3
New Member
 
RodrigoNeg
Join Date: May 2023
Posts: 7
Rep Power: 3
RodrigoNeg is on a distinguished road
I'm trying to generate the Bushing Joint with 2 Stiffness Coefficients over Z axis as you suggest, but I can only find one place to enter a Stiffness Coefficient for it. Please see the attached file for the Worksheet of the Stiffness and Damping Coefficients for the Bushing Joint. For this reason, I can't enter a positive AND a negative value for it. Could you elaborate on the procedure to get the 2 Stiffness Coefficients for rotation over Z? Thanks again!
Attached Images
File Type: jpg Stiffness Coefficients.jpg (61.9 KB, 13 views)
RodrigoNeg is offline   Reply With Quote

Old   July 6, 2023, 03:49
Default
  #4
siw
Senior Member
 
Stuart
Join Date: Jul 2009
Location: Portsmouth, England
Posts: 739
Rep Power: 26
siw will become famous soon enough
This is explained in the Mechanical User Guide help/wb_sim/ds_Joints_types_bushing.html.

In the Bushing Joint Worksheet, RMB on cell in the stiffness main diagonal and select Tabular. So select Delta Moment Z (N m), Per Unit Theta z (rad) and enter 3 datapoints for minimum, origin (0,0) and maximum.

Have a look at the Joint Stops and Locks in the Mechanical User Guide: help/wb_sim/ds_stops_locks.html. I've not needed use that, hence mentioning Bushing Joints, but it might suit your requirement.
Attached Images
File Type: jpg Screenshot 2023-07-06 075036.jpg (75.3 KB, 15 views)
RodrigoNeg likes this.

Last edited by siw; July 6, 2023 at 11:16.
siw is offline   Reply With Quote

Old   July 31, 2023, 13:02
Default
  #5
New Member
 
RodrigoNeg
Join Date: May 2023
Posts: 7
Rep Power: 3
RodrigoNeg is on a distinguished road
I can confirm that the simulation running using a bushing joint and tabular data with 3 points as suggested by SIW worked as expected.
Thank you very much!
RodrigoNeg is offline   Reply With Quote

Old   August 3, 2023, 03:45
Default
  #6
New Member
 
Dancan Mumo
Join Date: Aug 2023
Posts: 1
Rep Power: 0
Mumo is on a distinguished road
How can I really correct an error on "No DPS Connection" on ansys
Mumo is offline   Reply With Quote

Reply

Tags
ansys mechanical, restrict movement, revolute joints

Thread Tools Search this Thread
Search this Thread:

Advanced Search
Display Modes

Posting Rules
You may not post new threads
You may not post replies
You may not post attachments
You may not edit your posts

BB code is On
Smilies are On
[IMG] code is On
HTML code is Off
Trackbacks are Off
Pingbacks are On
Refbacks are On


Similar Threads
Thread Thread Starter Forum Replies Last Post
Hardware Suggestions for Ansys Mechanical, Sherlock and Mechanical Kips Hardware 8 October 17, 2022 18:57
Direction of rotation Gab CFX 6 November 16, 2017 17:19
ANSYS mechanical for Hot Isostatic Pressing hybrid25 System Analysis 0 February 5, 2016 03:20
EM Force data mapping from Maxwell to ANSYS Mechanical vahidasadzadeh ANSYS 0 October 25, 2015 07:01
Regarding the rotation direction HSeldon FLUENT 2 October 9, 2006 04:30


All times are GMT -4. The time now is 06:40.